Tap G code- Fanuc 10T

[cormigu]

Hi Guys,

I need to make a 6-32 Tap hole,but I don't know the code line(G code).

 

Please help...

[Russh67]

lathes are tricky

 

rigid tapping this may help.

 

O0018

T0606

G0X0.Z.1M08

M29 (may or may not need this)

G84 Z-.975 R0.1 F.03125 S600 M03 (Rigid tap Cycle)

G0Z.1M09

G80

G28 U0 W0.

M5

M30

 

Note per feed per rev feed is pitch of 6-32.

[strabe]

It's been a while but I think it's G32 on Fanuc lathes.

[Allan]

Yes G32/G33 is the ticket, you will not be able to rigid on a 10T, you'll need to use a floating tap holder.

Some machines will alow you to M04 without M05ing.

 

so it's like

 

G97 M03 S200

G00 X0. Z.25

G32 Z-.5 F.03125

M05

M04

G32 Z.25 F.03125

G00 X10. Z 5.

...

[Russh67]

Cormigu:

 

I apologize for giving you bad information, those guys are right. I was wrong and stand corrected. Didn't read what you had close enough...My Bad

[cormigu]

Thx Guys for help me,I figure out my program. it 's work fine.

 

NO.6-32 RH TAP)

N1020 G0 T0505

M08

N1030 G18

N1035

N1040 G97 S100 M03

N1050 G0 G54 X0. Z.25

N1060 Z.1

N1070 G99 G1 Z-.255 F0.03125

 

N1080 M05

N1090 G97 S100 M04

N1100 Z.25

N1110 M05

N1120 G97 S500 M03

N1130 G28 U0. W0.

N1140 G00 T0500

N1145 M01

[Allan]

You'll want to change that G01 to a G32 because the feed override is active on a G01 not a G32