52 replies to this topic

[tonyjohnson]

I have a new Mazak e500h and im trying to create a 45 deg face tool for face and turn operations with no success.Has anyone tried to create tools?My dealer and I thought it was strait forward but the m03 or m04 is posted wrong or the angle is doubled during posting.

[tonyjohnson]

Im using X5 mu1 with post from inhouse solutions for Integrex e 500h. thks

[Jeremy Herron@DBS Solutions™]

You mean like this?

Attached Files

•  45 tool.png   5.62K   69 downloads

[Wes@M.A.D.]

Are you trying to get a B axis output of 45 degree's with a straight holder? or just define a tool at 45?

[K2csq7]

.

[Jeremy Herron@DBS Solutions™]

This is how I do it ...

















and I get this code...


N1
(T1 | OD ROUGH RIGHT - 80 DEG.       |  ID CODE - 1.)
(TOOLPATH GROUP - TOOLPATH GROUP-2)
G123.1
M901
M202
G53.5
T1.01 M6
G28 U0. V0.
G28 W0.
M250
G0 B45.
M251
G53.5
G18
G50 S6000 R1
G96 S200 M03 R1
G0 X10.14142 Z.07071
G99 G1 X10. Z0. F.01
X0.
Z.1
G28 U0. Y0.
G28 W0.
M05
M01
M30

At least I think that is what you are after.

[tonyjohnson]

[At least I think that is what you are after.]



You read my mind.I want an M04 so I used a Left-164 tool and rotated it B180, comp right ( code and backplot) looked good.I guess it was straigt forward.Curious how to make this less redundant.Do I modify and save the default setting  for face and turn ops or modify the post (rather not)?How did u get the T01.01?That would be nice.

[tonyjohnson]

Thanks for all the replies

[Jeremy Herron@DBS Solutions™]

for m04 , pick the left handed tool and the only thing you have to change is this....





everything else is the same. If you have the inhouse post, you should have this...




for "A" definition tools set to 1, "B" set to 2, "C" set to 3, and so ...

[tonyjohnson]

Thks again.

[Jeremy Herron@DBS Solutions™]

Anytime. Glad to help.

[tonyjohnson]

I noticed the post added a G28 home move and repeated the work coor along with a B axis move(doesnt happen with rotation box left alone)for the turn move after facing.If I left the B rotation out (accidently because Im human)the B axis defaults to 90 deg.(not good)I tried to edit tool permanently but .





(PROGRAM NAME -  T   DATE=DD-MM-YY -  23-04-12  TIME=HH:MM -  15:43 )
(POST LICENSE - IN-HOUSE SOLUTIONS INC.)
(T1  | MCMNN- L-164C - CNMG-432       |  DIA. - 1  |  SUFFIX - 1. |  INSERT - CNMG-432)
G20 G69 G80 G40 G18 G90 G94
M205
(T1  | MCMNN- L-164C - CNMG-432       |  DIA. - 1  |  SUFFIX - 0. |  INSERT - CNMG-432)
(TOOLPATH GROUP - TOOLPATH GROUP-1)
G20 G10.9 X1
N1 G91 G30 P3 X0.
N1 G30 P3 Y0. Z0.
M901
M202
T1.01 T1 M06
G91 G30 P3 X0. Z0.
G90
M108
G0 G90 G53 B45.
M107
G54
G90 G43 P1 X4.278 Y0. Z0. H#3020
G18
M239
G92 S6000 R1
G96 S500 M204 R1
G95 G1 X-.0625 F.01
G91 G28 X0.------here
G28 Y0. Z0.
G90
T1
G54------here
M108
G0 B45.----- here
M107
G0 X4.078 Y0. Z0.
Z.1
G1 Z0.
Z-2.3238
X4.2194 Z-2.2531
M205
G91 G28 X0.
G28 Y0. Z0.
G90
M30

[tonyjohnson]

Misc values must match.Sorry

[Colin from CNC Software]

I've noticed the views on this topic going up, but nobody posting. Feel free to post your own tips, or as questions if you have them.

I was give a big list of other Tips/Tricks with Lathe by some of the Developers here at CNC, I've just been so busy I haven't gotten a chance to post them yet. More to follow...

[tonyjohnson]

That would be great Colin.I have looked here many times for the lastest post but found none.

[Colin from CNC Software]

Time for an update.

When creating a new Lathe Tool, the Lathe Tool Setup dialog box will show how the tool is loaded Graphically.



In the Lathe Tool Manager (or in the Tool List in an Operation) the graphics will indicate the insert direction. The Inserts shown in Orange are defined as "Insert Down" and the yellow inserts are defined as "Insert Up".



Sometimes with ID work there is very little clearance between the Tool/Holder and the part. This can cause a false collision warning if the tool is too close to the part. In that case you may need to reduce the entry/exit clearance in the Lathe Stock Update dialog, located in the Lathe Operation Parameters.



It’s common for a lathe holder to support multiple inserts, for example different corner radii.  Our tool catalogs contain most of the holder/insert combinations, but not all of them.  In that case, you can define your own tool by selecting the holder from a holder catalog, and the insert from the insert catalog.  You can even combine a lathe metric insert with an inch holder, or a lathe inch insert with a metric holder. Remember to save these custom built tools to a Lathe Tool Library for future use.
Define Tool:

Inserts:


I've uploaded an example file to the FTP site. It is named "RIGHT HAND VS LEFT HAND - PCLNR3225P12-R08.MCX-5" and is located in the "Lathe" sub folder.

When you are setting up a new Lathe Tool, I recommend you use the "Draw Tool" button on the "Define Tool" dialog box. This will draw a wireframe representation of your tool, and will show you the clearance angles that are setup for that tool (indicated by the red and purple circles). If the orientation of the tool looks correct on the screen, then the tool is properly setup.

Let me know if anyone has questions about creating a Lathe Tool and I'll provide some follow-up information.

[Mick]

Does anyone here using Sandvik Coromant "Twin Tools" or even their Corplex MT combined Milling and Turning tool? If so, I'd be curious to see how you set up and apply these in Mastercam.

These reply on the M602/603 commands (on the Okuma Multus) to orientate the tool to use (for example) the CNMG insert, or the DNMG insert.

The Coroplex MT is tricky, as it is a R390 two insert endmill, and a CCMT and DCMT turning tool combined.

[Jeremy Herron@DBS Solutions™]

On the Integrex I use tool orientation, other 0, 90, 180, or 270.

[Greg Williams]

I use a misc integer. You can also use the tool orientation 180 deg

[Glenn Bouman]

Quote

When in VTL mode if you want to make your dimensions display in the orientation you would expect you need to make a new construction plane. Go to Planes, planes by geo, pick a horizontal line, then a vertical line. X should face right, Y should face up.
Save that new plane as a unique name "drafting".

That works or just click on Planes = Gview