Post remove decimal

[Iceman_one01]

Hey guys,

We are using the standard MPLFAN post from mastercam,

our lathe is a regular 2 axis single turret with a fanuc 0iTD controller.

The current posts for outside thread.

G20

(TOOL - 5 OFFSET - 5)

(OD THREAD RIGHT INSERT - NONE)

( OD THREAD )

G0 T0505

G97 S400 M03

G0 G54 X.5737 Z.2167

G76 P010029 Q.001 R.001

G76 X.2993 Z-1. P372 Q70 R0. E.0625

G28 U0. W0. M05

T0500

M30

The problem seems to be the first g76 line.

G76 P010029 Q001 R.001 the controller complains about the decimal point for the Q.

How can I modify the post to remove the Decimal point for this Q only?

Thank you.

Mike

[ajmer]

try looking for this line in the post

fmt Q 2 thdlast$ #Last depth cut in thread

try changing the 2 to a 16

[NOTW Programmer]

Fire up the POST debugger and track the postblock that is outputting that line of code, you can then format the instruction to be outputted just like the second line Q value; not sure if changing the quantity of characters to 16 will fix the issue.

[Iceman_one01]

One more thing!

We are using the standard MPLFAN post from mastercam,

our lathe is a regular 2 axis single turret with a fanuc 0iTD controller.

The current posts for outside thread.

G20

(TOOL - 5 OFFSET - 5)

(OD THREAD RIGHT INSERT - NONE)

( OD THREAD )

G0 T0505

G97 S400 M03

G0 G54 X.5737 Z.2167

G76 P010029 Q.001 R.001

G76 X.2993 Z-1. P372 Q70 R0. E.0625

G28 U0. W0. M05

T0500

M30

I need to change or format the E.0625 value for the feed to F.0625.

How can I do this?

Thank you.

Mike

[DannyMack]

"Find this line in your post"

# --------------------------------------------------------------------------

# Format statements - n=nonmodal, l=leading, t=trailing, i=inc, d=delta

# -------------------------------------------------------------------------

Bellow you will see your "fs2" or Format statements you will need to add a statement

because if you change one that already exsits you will most likely change others as well.

 

ADD THIS at the bottom of the fs2 lines

fs2 27 0 4 0 4 #Decimal, absolute, 3 place

 

Then search for your fmt "Q" line under your #Thread output it will probably have a 2 next to it.

Change it to look like this.....

fmt "Q" 27 thdfirst$ #First depth cut in thread

 

 

 

To change the E output Look for this....

 

#String and string selector definitions for NC output

# --------------------------------------------------------------------------

#Address string definitions

stra : "A" #String for address A

strd : "D" #String for address D

stre : "F" #String for address E Change E to F

strf : "F" #String for address F

stri : "I" #String for address I

[MSL]

Hey guys,

We are using the standard MPLFAN post from mastercam,

our lathe is a regular 2 axis single turret with a fanuc 0iTD controller.

The current posts for outside thread.

G20

(TOOL - 5 OFFSET - 5)

(OD THREAD RIGHT INSERT - NONE)

( OD THREAD )

G0 T0505

G97 S400 M03

G0 G54 X.5737 Z.2167

G76 P010029 Q.001 R.001

G76 X.2993 Z-1. P372 Q70 R0. E.0625

G28 U0. W0. M05

T0500

M30

The problem seems to be the first g76 line.

G76 P010029 Q001 R.001 the controller complains about the decimal point for the Q.

How can I modify the post to remove the Decimal point for this Q only?

Thank you.

Mike

 

We do have the same controller on our new Mori Dura Turn lathes. I have been working on a post on and off. I know there is some work that needs to be done for canned cycles.I have to take a look at that. How is your drilling cycle working?

A format statements will take care of the decimal point.