Jump to content

Welcome to eMastercam

Register now to participate in the forums, access the download area, buy Mastercam training materials, post processors and more. This message will be removed once you have signed in.

Use your display name or email address to sign in:

A286 steel?


BenK
 Share

Recommended Posts

It work hardens pretty easy. If you are familiar with milling superalloys with ceramics and you have alot of material to remove I have had some sucess with it. If not stay away from them because it a bit of a leap from the norm. If you run ceramics I suggest NTK and dry, otherwise I usually jack my coolant concentration up to 10-15% if I have a lot to run. Threadmill or rollform threads. Carbide drills if you can afford them. Variable helix variable pitch endmills for solid carbide. Stay away from square shoulder inserted cutters, button cutters are your friend here.

Link to comment
Share on other sites

I've always treated it like inco 625. Thin walls will move (push) with moderate tool pressure.

I am dying to test some HSS paths on some high temp.

We are eating Ti up with them. And tool life in the hours.

Like Jeremy says, do not work harden it!

Link to comment
Share on other sites

Nasty Nasty stuff!

Have a job with lots of small deep radiused slots. (.12W x .6L x .900 Deep on a 1.5 radius..Belive me, in this stuff, .900 is DEEP!) Lets just say I changed lots of tools.....some every part.

If Carbide isn't an option, Cobalt drills, depending on the brand and a lot of luck, hold up rather well.

About 40 SFM :o

I had to roll tap 0-80's in this stuff, after heat treat..Thank God for Molly-dee!

Good luck

You have my sympathy!

Link to comment
Share on other sites

Treat it like Inconel 625. I make lots of R&D parts out of this. It work hardens and grows back, moves all over the place. I would personally like to cut inco 625 over this. Every batch is different also. I do turn and mill work. Use of low stepover max depth of cut is the way to mill. Turning I use kc5510 grade from kennametal. Drilling I use Gurhing with firex coating 70sfpm.

 

This might sound conservative to some but my parts are six figures easy and we don't get a setup part.

 

I would never recommend HSS/cobalt unless your drilling a small a286 fastener out.

 

Dynamic high speed tool paths work really well with superalloys. Don't be afraid to use tool inspection points. I usually put a 30 min check when hogging.

Link to comment
Share on other sites

Join the conversation

You can post now and register later. If you have an account, sign in now to post with your account.

Guest
Reply to this topic...

×   Pasted as rich text.   Paste as plain text instead

  Only 75 emoji are allowed.

×   Your link has been automatically embedded.   Display as a link instead

×   Your previous content has been restored.   Clear editor

×   You cannot paste images directly. Upload or insert images from URL.

 Share

  • Recently Browsing   0 members

    • No registered users viewing this page.

Join us!

eMastercam - your online source for all things Mastercam.

Together, we are the strongest Mastercam community on the web with over 56,000 members, and our online store offers a wide selection of training materials for all applications and skill levels.

Follow us

×
×
  • Create New...