Can you Post feed rate on every line?

[nakaroto24]

Hi

 

Is there a way to edit the post processor and post the feed rate on every line? Similar to what "Highfeed" does. I'm using mastercam X6 and a post processor provided by hurco.

 

Thanks

[Guess_who]

This sections in your post change the feed to *feed, an "*" forces output.

 

 

[b]plinout [/b]	 #Output to NC of linear movement - feed
 pcan1, pbld, n$, sgfeed, sgplane, `sgcode, sgabsinc, pccdia,
 pxout, pyout, pzout, pcout, feed, strcantext, scoolant, e$
[b]pcirout[/b]		 #Output to NC of circular interpolation
 pcan1, pbld, n$, `sgfeed, sgplane, sgcode, sgabsinc, pccdia,
 pxout, pyout, pzout, pcout, parc, feed, strcantext, scoolant, e$

 

Should look like this when you're done

 

plinout		 #Output to NC of linear movement - feed
  pcan1, pbld, n$, sgfeed, sgplane, `sgcode, sgabsinc, pccdia,
    pxout, pyout, pzout, pcout, *feed, strcantext, scoolant, e$
pcirout		 #Output to NC of circular interpolation
  pcan1, pbld, n$, `sgfeed, sgplane, sgcode, sgabsinc, pccdia,
    pxout, pyout, pzout, pcout, parc, *feed, strcantext, scoolant, e$

[nakaroto24]

This sections in your post change the feed to *feed, an "*" forces output.

 

 

[b]plinout [/b]	 #Output to NC of linear movement - feed
 pcan1, pbld, n$, sgfeed, sgplane, `sgcode, sgabsinc, pccdia,
 pxout, pyout, pzout, pcout, feed, strcantext, scoolant, e$
[b]pcirout[/b]		 #Output to NC of circular interpolation
 pcan1, pbld, n$, `sgfeed, sgplane, sgcode, sgabsinc, pccdia,
 pxout, pyout, pzout, pcout, parc, feed, strcantext, scoolant, e$

 

Should look like this when you're done

 

plinout		 #Output to NC of linear movement - feed
 pcan1, pbld, n$, sgfeed, sgplane, `sgcode, sgabsinc, pccdia,
 pxout, pyout, pzout, pcout, *feed, strcantext, scoolant, e$
pcirout		 #Output to NC of circular interpolation
 pcan1, pbld, n$, `sgfeed, sgplane, sgcode, sgabsinc, pccdia,
 pxout, pyout, pzout, pcout, parc, *feed, strcantext, scoolant, e$

 

hi,

 

Thanks for the reply. My post look a little different

 

# Axis Motion Definition section

# --------------------------------------------------------------------------

 

pccdia2 # Cutter Compensation2

# tloffno$ = t$

if ccomp$ <> 4, tloffno$

 

pccdia # Cutter Compensation

if ccomp$ <> 0, pccdia2

 

prapid$ # Linear line movement - at rapid feedrate

n$, sgplane, sccomp, sgcode, x$, y$, z$, !fr$,e$

 

pzrapid$ # Linear movement in Z axis only - at rapid feedrate

n$, sccomp, sgcode, z$,e$

 

plin$ # Linear line movement - at feedrate

n$, sccomp, pccdia, sgcode, x$, y$, z$, pfr, pcan,e$

 

pz$ # Linear movement in Z axis only - at feedrate

n$, sgcode, z$, pfr,e$

 

pcir$ # Circular interpolation

if plane$ = 2, n$, sgplane, sccomp, *sgcode2, x$, y$, z$, pijk, pfr, pcan,e$

else, n$, sgplane, sccomp, *sgcode, x$, y$, z$, pijk, pfr, pcan,e$

[Bryan Johnson]

Pfr is the post block for your feed output.

Keep in mind that forcing it to output dos not change it's value. It will simply repeat on every line.

 

[Guess_who]

As Bryan said, look at the section in your post "pfr" and show us what that looks like.

 

Just curious, but why do you want the federate to post out on every line?

[nakaroto24]

As Bryan said, look at the section in your post "pfr" and show us what that looks like.

 

Just curious, but why do you want the federate to post out on every line?

 

I'm having problems running high speed tool paths on older machines with not many look-ahead options. I get some slow downs and retract feed rate is not optimal it ignores what mastercam says.

 

pfr # Feedrate W/O Negative Feedrates

if fr$ > 0, fr$

[Guess_who]

Well let me start by saying that I don't use the fr$ in my posts so I'm probably not the best guy to give you an answer. But it looks as simple as adding an asterisk in front of the fr$ after the comma. But I'm not familiar with the fr$ function.

 

Try editing the line to look like this and see if it works.

 

if fr$ > 0, *fr$.