Jump to content

Welcome to eMastercam

Register now to participate in the forums, access the download area, buy Mastercam training materials, post processors and more. This message will be removed once you have signed in.

Use your display name or email address to sign in:

Camplete Setup


JB7280
 Share

Recommended Posts

2 hours ago, tim_h said:

Now it visually looks ok. BUT i'm getting multiple G54's. I only need the one G54 on the Matsuura MX520. It has TWP .

You can set a default WOrk Offset or you can override the incoming work offsets, or, as it is set now, you are responsible.

CLose all sessions of CAMplete. Re-Open CAMplete. No project. Go to the Manage tab, go to the tools ribbon, then go to Options. Select the File Types Tab on the left. In the additional Options section section set the following preferences; 

NCI - Apply Tool CS To Datums (activate this)

NCI - Datum Index - Datum To Use. (You can set this to any number you want. 0 = G54, 1 = G55, 3 = G56, 6 = G54.1P1, 7 = G54.1 P2, etc... - I have mine set to 1)

NCI - Datum Index - Override Values (if you activate this, then you lose control in Mastercam - I have this deactivated)

NCI - Default Datum - Default Value (You can set this to any number you want. 0 = G54, 1 = G55, 3 = G56, 6 = G54.1P1, 7 = G54.1 P2, etc... - I have this set to 1)

NCI - Default Datum - Use Default Value when Datum Is 0 in NCI (if you activate this, then you lose control in Mastercam)

NCI - Use Cached Datums (activate this)

 

In the Advanced Properties I have Treat WCS Datums As Multiple Fixtures activated, and Read Datum Index From NCI activated. 

 

Click Close. 

Click Machines in the Resources Ribbon.

Select your machine. Click the Edit Button. In the Program CS tab, you'll see a CAM Index Column. By default they are all -1. Set G54 to 0, G55 to 1, G56 to 2, G57 to 3, etc... down as many as you want to set. 

Click OK. 

Click Close.

Exit CAMplete. 

 

You should be good to go after that. 

  • Like 1
Link to comment
Share on other sites

Join the conversation

You can post now and register later. If you have an account, sign in now to post with your account.

Guest
Reply to this topic...

×   Pasted as rich text.   Paste as plain text instead

  Only 75 emoji are allowed.

×   Your link has been automatically embedded.   Display as a link instead

×   Your previous content has been restored.   Clear editor

×   You cannot paste images directly. Upload or insert images from URL.

 Share

  • Recently Browsing   0 members

    • No registered users viewing this page.

Join us!

eMastercam - your online source for all things Mastercam.

Together, we are the strongest Mastercam community on the web with over 56,000 members, and our online store offers a wide selection of training materials for all applications and skill levels.

Follow us

×
×
  • Create New...