Sign in to follow this  
motor-vater

5 AXIS MACHINE PARAMETER QUESTION

Recommended Posts

The Machines are Mori NMV5000's maybe 30i controls but would really have to check them. My Question is about parameter 19754.5, currently the setting in this parameter requires you to return to CO, BO before calling a G43.4 and worse have to return to zeros when the next G43.4 is call elsewise the machine just considers it a zero where ever it is and will make a new rotation from that position. I think if I change this parameter I can utilize the functionality of our new post that does not return to zero's inbetween 5 axis toolpaths... Any body have any experience with this? I asked the Mori apps engineer and he said he was surprised the machine was even set up like this but was going investigate further.. That was weeks ago. Any advise is appreciated here...

Share this post


Link to post
Share on other sites

Our matsuura 30i don't care when you turn it on.

  • Like 1

Share this post


Link to post
Share on other sites

Hi Pete,

There is a Mori App's guy that is a member here. I think his name is Mark? I also think he changed his screen name here within the last few years.

Hopefully he will chime in.

The issue with all of the new 5-Axis Functions (TWP, TCPC, DWO, WSEC, etc.), is that there are several dozen parameters which are interlinked. 

  • Like 1

Share this post


Link to post
Share on other sites

We made programs for the NMV3000 machine and I didn't get an answer 6 years ago about that very question when someone was a VP at Ellison. I am a go out and give it a try kind of person Pete. Make a test block and do about 10-20 different things on it to test. Then if it works you pass that information on to CG Tech to have the VMC updated and then you should be good to go.

Shot me an email and I will share the PDF I have on 5 axis Parameters and other things that help.

Share this post


Link to post
Share on other sites

On our Doosan machines, we have have no issue with TCP as long as these parameters are set this way.

19696.5(WKP) must be 0

19746.4(TBP) must be 1

 19754.5(INZ) must be 1

  • Like 2

Share this post


Link to post
Share on other sites
5 hours ago, crazy^millman said:

We made programs for the NMV3000 machine and I didn't get an answer 6 years ago about that very question when someone was a VP at Ellison. I am a go out and give it a try kind of person Pete. Make a test block and do about 10-20 different things on it to test. Then if it works you pass that information on to CG Tech to have the VMC updated and then you should be good to go.

Shot me an email and I will share the PDF I have on 5 axis Parameters and other things that help.

Thats what I am doing as we speak, so far so good. Vericut already does not have a problem with the post output. Kind of how we found it was an issue. Luckily both 5 axis paths required a big b axis move so at the machine after it ran the first path it immediately alarmed out on the second g43.4 when trying to rotate to the next position, because it would have had to rotate past the limits... Vericut gave us no warning of impending doom!

Share this post


Link to post
Share on other sites
1 hour ago, motor-vater said:

Thats what I am doing as we speak, so far so good. Vericut already does not have a problem with the post output. Kind of how we found it was an issue. Luckily both 5 axis paths required a big b axis move so at the machine after it ran the first path it immediately alarmed out on the second g43.4 when trying to rotate to the next position, because it would have had to rotate past the limits... Vericut gave us no warning of impending doom!

Been there done that plenty of times. Test and test and then go back and show what it is really doing and they will get it fixed. 

Share this post


Link to post
Share on other sites
1 hour ago, motor-vater said:

Vericut gave us no warning of impending doom!

Vericut is only as good as the inputs it has been given.  They really need to make it such that the basic Vericut setup based on a parameter dump, then write the added PMC type functionality for a machine in the vericut "post".

  • Like 1

Share this post


Link to post
Share on other sites
7 hours ago, PAnderson said:

On our Doosan machines, we have have no issue with TCP as long as these parameters are set this way.

19696.5(WKP) must be 0

19746.4(TBP) must be 1

 19754.5(INZ) must be 1

Our Matsuura 5-Axis machines are set this way as well.

  • Like 2

Share this post


Link to post
Share on other sites

Create an account or sign in to comment

You need to be a member in order to leave a comment

Create an account

Sign up for a new account in our community. It's easy!

Register a new account

Sign in

Already have an account? Sign in here.

Sign In Now
Sign in to follow this  

  • Recently Browsing   0 members

    No registered users viewing this page.

Join us!

eMastercam - your online source for all things Mastercam.

Together, we are the strongest Mastercam community on the web with over 56,000 members, and our online store offers a wide selection of training materials for all applications and skill levels.

Follow us