GOTO command not working with 5 axis program

[Shiva.aero]

Hello everyone!

I have no issues in running GOTO command with 3 axis program.

But with 5 axis program, the GOTO and GOTOC are not working.

Can anybody help to understand this problem better.

Controller is Siemens Sinumerik 840d.

Thank you.

[Grievous]

Share your code and explain what you are looking for

[Shiva.aero]

1 hour ago, Grievous said:

Share your code and explain what you are looking for

Thanks for the reply.

Shortly I will share the code.

But here is the quick description:

1. I made a rotational Toolpath transform. There were 21 toolpath after the transform.

2. Since the search block takes time because of program length, I decided to skip the blocks using Goto command.

3. So at the start of the program I gave a label and at the start of each Toolpath I gave a destination.

Like following example:

Goto Label2 

Label2:

... Toolpath codes...

Label3:

... Toolpath codes...

etc.,

4. Now I change the variable name at the start depends on where to jump.

5. This works perfectly fine for 3 axis program. But the same is not working for 5 axis program. It throws up an error with "Alarm 14080: Jump destination not found"

6. I ensured the correct syntax, but still it is not working

 

 

[Shiva.aero]

7 hours ago, Grievous said:

Share your code and explain what you are looking for

Here i attached the program. Please check.

OPN20_WITHJUMP.MPF

[Shiva.aero]

On 11/16/2021 at 11:27 AM, Shiva.aero said:

Here i attached the program. Please check.

OPN20_WITHJUMP.MPF

Basically I want to skip or goto the particular instance of the rotational transform.

Not only goto, even changing the C axis value in Cycle800 is also not working.

Anybody have any clue about this problem?

[Grievous]

Well ..you can get inspired  from this

JUMPAROUND.MPF

[Shiva.aero]

16 hours ago, Grievous said:

Well ..you can get inspired  from this

JUMPAROUND.MPF

 

16 hours ago, Grievous said:

Well ..you can get inspired  from this

JUMPAROUND.MPF

Grievous, I don't have any problem using Goto command, frame rotation commands & changing angle values in Cycle800 command in my 3-axis program.

But, in 5 axis program, all these are not working. I tried switching off TRAORI command by using TRAFOOF command and I also I tried using ORIWKS command. But nothing works!

[cncappsjames]

On 11/19/2021 at 3:34 AM, Shiva.aero said:

Basically I want to skip or goto the particular instance of the rotational transform.

Not only goto, even changing the C axis value in Cycle800 is also not working.

Anybody have any clue about this problem?

You can't re-orient a tilt/rotary while CYCLE800 is active.

[Shiva.aero]

The problem is solved with the help of Christopher Pollack from Siemens Industries.

The problem was due to the buffer memory size and it has nothing to do with the 5 axis commands.

By default my controller reads only 500 lines into the buffer and since the GOTO destination was placed after 500 lines, I got the "Jump destination not found" error, even though the GOTO destination was present with proper syntax.

And I got another reason to use Arc/Spline interpolation!

Thank you.