Jump to content

Welcome to eMastercam

Register now to participate in the forums, access the download area, buy Mastercam training materials, post processors and more. This message will be removed once you have signed in.

Use your display name or email address to sign in:

Indicating bore with Probe on Haas


Recommended Posts

I mat have to cut some molded parts on a mill for a second opp.  Its a round part with a bore.  Bosses want to have each part indicated, I know how to do that.  Problem I'm seeing is that the Indicate Bore routine on the Haas doesn't ask for a depth, you have to take it to the depth and then run the program.  

How would I go about doing that?  Write the coordinates BEFORE the probe program ?

Link to comment
Share on other sites
13 minutes ago, AMCNitro said:

I mat have to cut some molded parts on a mill for a second opp.  Its a round part with a bore.  Bosses want to have each part indicated, I know how to do that.  Problem I'm seeing is that the Indicate Bore routine on the Haas doesn't ask for a depth, you have to take it to the depth and then run the program.  

How would I go about doing that?  Write the coordinates BEFORE the probe program ?

you set the probe up as a tool and just program it to the center of the bore and to the z depth that you want then call the probe bore sub

Link to comment
Share on other sites

This is a sub I call to...it'll look something like this...though mine is not for a Haas, the premise will be the same

(******************)
(*PROBING ROUTINES*)
(******************)
N8901(PROBE 1 ROUTINE - FUSION LASER BENCH)
(PROBE 1 POSITIONS AFTER INITIAL OFFSETS SET)
()
(PROBE POSITION 1)
()
Z1.
G65P9809T1X.155Y-.1467F100.
G65P9809T1Z.1F100.
G65P9810Z-.565F100.  (This goes down inside the bore)
G65P9814D.22S#19(X,Y OFFSET)     (This calls the ID cycle)
G65P9810Z.25F100.
G65P9810X.625Y-.1467F100.
G65P9811Z-.125S#19(Z OFFSET)
G65P9810Z.1F100.
G28Z1.
()
(END PROBE 1)
M99

  • Like 4
Link to comment
Share on other sites

Below is for a Haas, you will want to use the inspection plus macros and not use the Haas GUI  

You can find the inspection plus manual here:

https://service.haascnc.com/sites/default/files/Locked/2/Renishaw_Programming_Manual_H_2000_6222_0A_B.PDF


M06 T24 (PROBE)
G00 G90 G154 P1 X0. Y0. 
G43 H24 Z3. 
G65 P9832 (TURN ON PROBE) 
G65 P9810 Z0.2 F100. (PROTECTED MOVE) 

G65 P9810 Z-0.5 F100. (PROTECTED MOVE)
(S1=G54,S2=G55....G154P10=S154.10) 

G65 P9814 D1.75 S154.01 (BORE CENTER FIND) 


G65 P9810 Z0.2 (PROTECTED MOVE)

G65 P9833 (TURN OFF PROBE) 


G00 G53  Z0. 
(T10) 

(START MACHINING) 

  • Like 3
Link to comment
Share on other sites
On 11/19/2021 at 7:56 AM, civiceg said:

Below is for a Haas, you will want to use the inspection plus macros and not use the Haas GUI  

You can find the inspection plus manual here:

https://service.haascnc.com/sites/default/files/Locked/2/Renishaw_Programming_Manual_H_2000_6222_0A_B.PDF


M06 T24 (PROBE)
G00 G90 G154 P1 X0. Y0. 
G43 H24 Z3. 
G65 P9832 (TURN ON PROBE) 
G65 P9810 Z0.2 F100. (PROTECTED MOVE) 

G65 P9810 Z-0.5 F100. (PROTECTED MOVE)
(S1=G54,S2=G55....G154P10=S154.10) 

G65 P9814 D1.75 S154.01 (BORE CENTER FIND) 


G65 P9810 Z0.2 (PROTECTED MOVE)

G65 P9833 (TURN OFF PROBE) 


G00 G53  Z0. 
(T10) 

(START MACHINING) 

I did it right from the machine control, I had to add some lines of code, but it was very easy.  Just saw what the machine wanted to do, and from there I figured out what it needed from me.

Thanks for this though.  And thanks to everyone that offered help

  • Like 1
Link to comment
Share on other sites

Join the conversation

You can post now and register later. If you have an account, sign in now to post with your account.

Guest
Reply to this topic...

×   Pasted as rich text.   Paste as plain text instead

  Only 75 emoji are allowed.

×   Your link has been automatically embedded.   Display as a link instead

×   Your previous content has been restored.   Clear editor

×   You cannot paste images directly. Upload or insert images from URL.

 Share

  • Recently Browsing   0 members

    • No registered users viewing this page.

Join us!

eMastercam - your online source for all things Mastercam.

Together, we are the strongest Mastercam community on the web with over 56,000 members, and our online store offers a wide selection of training materials for all applications and skill levels.

Follow us

×
×
  • Create New...