Mass Edit Rotary Axis

[JKLINE]

I'm looking at a mass edit to change all of the rotary diameter's in the toolpaths. Later to edit other boxes and even later creating toolpaths.

It wouldn't let me add the OperationIDs to a list unless I labeled the list as <int[]> do they have a different ID system than geometry?

I believed I have set up the parameters for the RotaryAxisParams but I'm not sure how to load it into the operation. My best guess is that it has something to do with my list not populating correctly.

            void changeOperations() {
                var operations = new List<int[]>();
                var rotaryPD = 0.0;
                DialogManager.AskForNumber("Enter New Rotary PD", ref rotaryPD);
                OperationsManager.RefreshOperationsManager(true);
                operations.Add(SearchManager.GetOperationIDs(true));
                var axisSub = new RotaryAxisSubstitution{
                     
                };
                var axisParams = new RotaryAxisParams{
                    Enabled = true, 
                    Diameter = rotaryPD,
                    AxisSubstitution = axisSub  
                };

                foreach (var selectedOperation in operations){
                    selectedOperation.RotaryAxis = axisParams;
                    selectedOperation.commit();
                }
                OperationsManager.RefreshOperationsManager(true);
            }

            changeOperations();

 

[Roger Martin from CNC Software]

A couple things. 

 var operations = new List<int[]>();

1> No. You don't want a List of arrays (of integers).

2> You have not retrieved the actual "operation" here. You are looping through the IDs.

  foreach (var selectedOperation in operations){
                    selectedOperation.RotaryAxis = axisParams;
                    selectedOperation.commit();
                }

 

Try this...

        private void ChangeOperations()
        {
            var rotaryPD = 0.0;
            DialogManager.AskForNumber("Enter New Rotary PD", ref rotaryPD);
            OperationsManager.RefreshOperationsManager(true);
            var operationIDs = SearchManager.GetOperationIDs(true);
            var axisSub = new RotaryAxisSubstitution
            {

            };
            var axisParams = new RotaryAxisParams
            {
                Enabled = true,
                Diameter = rotaryPD,
                AxisSubstitution = axisSub
            };

            foreach (var opID in operationIDs)
            {
                var op = SearchManager.GetOperation(opID);
                op.RotaryAxis = axisParams;
                op.Commit();
            }
            OperationsManager.RefreshOperationsManager(true);
        }

 

[JKLINE]

I also had to change "var axisSub = new RotaryAxisSubstitution". But everything works other than that, thank you.

Additionally, it does not make ALL the operations dirty, only some of them. Should I have it regen the toolpaths just in case?

 

            void ChangeOperations(){
                var rotaryPD = 0.0;
                DialogManager.AskForNumber("Enter New Rotary PD", ref rotaryPD);
                OperationsManager.RefreshOperationsManager(true);
                var operationIDs = SearchManager.GetOperationIDs(true);

                var axisParams = new RotaryAxisParams
                {
                    Enabled = true,
                    Diameter = rotaryPD,
                    Type = RotaryAxisPositionType.AxisSubstitution
                };

                foreach (var opID in operationIDs)
                {
                    var op = SearchManager.GetOperation(opID);
                    op.RotaryAxis = axisParams;
                    op.Commit();
                }
                OperationsManager.RefreshOperationsManager(true);
            }

            ChangeOperations();

 

[Roger Martin from CNC Software]

Quote

Should I have it regen the toolpaths just in case?

If you make a change to an operation manually using Mastercam's User Interface Mastercam marks it 'dirty',

you should have your add-in mark it dirty, or just have it regen the toolpath.

[JKLINE]

Awesome, thank you. Works like a charm

 

            void ChangeOperations(){
                var rotaryPD = 0.0;
                DialogManager.AskForNumber("Enter New Rotary PD", ref rotaryPD);
                OperationsManager.RefreshOperationsManager(true);
                var operationIDs = SearchManager.GetOperationIDs(true);
                var axisParams = new RotaryAxisParams
                {
                    Enabled = true,
                    Diameter = rotaryPD,
                    Type = RotaryAxisPositionType.AxisSubstitution,
                    Direction = RotaryAxisDirection.CW,
                    AxisSubstitution = RotaryAxisSubstitution.SubsituteX
                };

                foreach (var opID in operationIDs){
                    var op = SearchManager.GetOperation(opID);
                    op.RotaryAxis = axisParams;
                    op.MarkDirty();
                    op.Commit();
                }
                OperationsManager.RefreshOperationsManager(true);
            }
            ChangeOperations();
            return MCamReturn.NoErrors;

 

[JKLINE]

It does however remove any "containment" in the geometry selection. Is this because I need to use more specific operation selections? Such as, chainBasedOperation? I do not see a surfaceBasedOperation (which is where the containment was lost.

[JKLINE]

I thought I was being clever by adding 

                        var array = ((ChainBasedOperation)op).GetChainArray();
                        op.RotaryAxis = axisParams;
                        ((ChainBasedOperation)op).SetChainArray(array);

But it didn't work  I still lose the avoidance region and containment region of the geometry selection.

[Roger Martin from CNC Software]

What is the exact operation "type" you are altering here?

A Surface operation? => Not with the NET-Hook API as this time.

[JKLINE]

These are the two different programs we use. Same toolpaths, different rotary diameter.

Even the surface programs have their rotary diameter changed. The only issue is when the toolpath has additional geometry.

Selected geometry is kept, avoidance/containment geometry is lost.

 

[Roger Martin from CNC Software]

Try this (it may or may not help) -

Change the Commit calls on the operations to include the 'false' parameter.

op.Commit(false);

[JKLINE]

It works. Thank you. 

            void ChangeOperations(){
                var rotaryPD = 0.0;
                DialogManager.AskForNumber("Enter New Rotary PD", ref rotaryPD);
                OperationsManager.RefreshOperationsManager(true);
                var operationIDs = SearchManager.GetOperationIDs(true);
                var axisParams = new RotaryAxisParams
                {
                    Enabled = true,
                    Diameter = rotaryPD,
                    Type = RotaryAxisPositionType.AxisSubstitution,
                    Direction = RotaryAxisDirection.CW,
                    AxisSubstitution = RotaryAxisSubstitution.SubsituteY
                };

                foreach (var opID in operationIDs){
                    var op = SearchManager.GetOperation(opID);
                    op.RotaryAxis = axisParams;
                    op.MarkDirty();
                    op.Commit(false);
                }
                OperationsManager.RefreshOperationsManager(true);
            }
            ChangeOperations();
            return MCamReturn.NoErrors;

 

[Roger Martin from CNC Software]

Something file in your memory about the NET-Hook API -
Whenever you are doing Commit on an Operation.
If you have not altered the geometry (chains, drill points, etc.) assigned to that operation.
In other words, you are just updating "parameters" of the operation.
Use the Commit overload that takes a boolean parameter and pass "false" -> op.Commit(false);

"false" here tells it not to look at (or touch) the geometry in the operation when doing the Commit (update).