Changing output of G code call

[Chrisd9300]

I need to edit my post to change the output of a drilling operation. 
 

currently when I post a side drilling operation it posts as follows

Z-.305 C180.

X1.2 Y0.

G98

G87 X.5 R0. Q500 F1.57

G80

 

i need it to post as follows

Z-.305 C180.

X1.2 Y0.

G98

G87 Z-305 C180. X.5 R0. Q500 F1.57 m68

G80

 

[Kalibre]

Depending on what post you're using, you should just be able to modify your mdrill$ post block.

Original probably looks like:

mdrill$         #Canned drill cycle, mill
      pdrlcommonb
      pcan1, pbld, n$, *sgdrlref, pgdrlout, pxout, pyout, pzout,
        pcout, prdrlout, dwell$, pffr, strcantext, e$
      pcom_movea

Change to:

mdrill$         #Canned drill cycle, mill
      pdrlcommonb
      pcan1, pbld, n$, *sgdrlref, pgdrlout, pfxout, pfyout, pfzout,
        pfcout, prdrlout, dwell$, pffr, strcantext, "m68", e$
      pcom_movea

 

As always, save a back-up before making any changes.

[crazy^millman]

Kalibre, I think they meant a M68 upper case not lower case. Hopefully the machine will not alarm out with lower case letters.

Good call with using pfcout and pfzout to force the C and Z axis outputs.

[Kalibre]

21 hours ago, crazy^millman said:

Kalibre, I think they meant a M68 upper case not lower case. Hopefully the machine will not alarm out with lower case letters.

Good call with using pfcout and pfzout to force the C and Z axis outputs.

You're probably correct. I just carried on with how Chris wrote it, lord knows there's more than a few quirky controls out there.

[Chrisd9300]

Thank y’all for the replies. 
 

I was able to force the lock code outputs in the beginning of the post and I did go the route of forcing the Z and C outputs in the drill cycles.