X2 MPMaster??

[Guest]

I am getting a G94 output on all tools.

 

it looks to me like this is being output by the sgfeed variable however removing it did not remove the code

 

code:

---

Z.152                                            

G94 G01 Z.01 F60.

X1.2 F20.

---

How can I get this out of here?

[?Mark]

Hold on, John will be right with you...

 

[Hardmill]

quote:

---

Hold on, John will be right with you...

---

Yeah where is Pinky At ??

Didnt he just atart a new gig today ??

 

 

PEACE

[Mike-T]

I've noticed it shows up when doing alot of different rotations in 3+2. Looking forward to

a resolution.

[john316]

.

 

It's tied into your inverse feed (G93) and unit feed (G94)

 

Check your settings for 4-axis feed and rotary in your Control def. and see if changing them makes a difference.

 

.

[Post dept]

John,

 

Are you using that post that I sent you the other day?

 

Brett

[Guest]

No Brett the X2 Mill off the site

[Hardmill]

Try here Pinky

Post geek Dave

 

 

PEACE

[Post dept]

The current version of mpmaster that's on the posts page has this line at the bottom of ptlchg_com

 

code:

---

if not(convert_rpd$), result = force(ipr_type,ipr_type)

---

remove that to get rid of the forced G94/G95.

 

We've switched to a new style with a switch called force_output to force out modal G codes for restarts. Expect to see this very soon.

 

Brett

[Storkman]

Don't xxxx off the post gods Regrind.

[Guest]

Looks like that got it, thanks Hardmill and Dave and Brett

 

[Hardmill]

quote:

---

Don't xxxx off the post gods Regrind.

---

Better to be pissed off.........

 

 

PEACE

[gcode]

I downloaded a fresh copy of the mpmaster

yesterday.

I could not get the "force output switch"

to work and I could not find the line

quote:

---

if not(convert_rpd$), result = force(ipr_type,ipr_type)

---

I had to # out the following lines to get rid of the G94 output at toolchanges

 

ptlchg_com #Tool change common blocks

#if force_output | sof,

# [

#result = force(ipr_type,ipr_type)

#result = force(absinc$,absinc$)

#]

[Guest CNC Apps Guy 1]

Brett's doing a great job with MPMaster.

 

We've worked together on the High Speed Machining Stuff a little bit.

[Post dept]

Gcode,

 

The force_output switch should be right at the top of the post, just below all the commented out header information:

 

force_output : 1 #0 = Modal G code output at toolchanges, 1 = Force output of all G codes (see also force_wcs)

 

Chris

[gcode]

I found that, but it had no effect

[kkominiarek]

I too need to block g94 from posting.

 

I #'d out the lines mentioned above....that worked but it also blocked the g90 at SOF. (at toolchange still output g90...this is good)

 

How do I get g90 back in there?

[kkominiarek]

bump

[Rob @ Target Machine]

code:

---

Change this:

 

ptlchg_com #Tool change common blocks

if force_output | sof,

[

result = force(ipr_type,ipr_type)

result = force(absinc$,absinc$)

]

 

to this:

 

ptlchg_com #Tool change common blocks

if sof, result = force(absinc$,absinc$)

---