Sign in to follow this  
Followers 0
K2csq7

Dynamic in Haynes 188

6 posts in this topic

Hola Commrades,

 

Got a job coming up with 18 windows; .770 X 3.015 w/ .325 rads in the 4 corners.

Through an .080 wall about 6" up off the table (turned part, I will have a cap on the top while milling for added support). It will be a 3+2 setup on a very old machine. Max RPM is about 2k. Max backfeedrate = 50 IPM. (and that's pushing it)blink.gif

 

 

When your all done laughing I'd like some suggestions welcome.gif!

 

I am planning on using a 5 fluted 5/16" Supermill at about 100 SFM & .001 CPT (to start with).

Plunging into a predrilled hole for entry.

I've got a .046 stepover in there now, and a toolpath radius of .050 (Dynamic Area). Filter = 1:1 total tolerance = .004, leaving .006 / side for finishing.

 

We have a similar job with more but smaller windows that runs on that machine and was programmed a long time ago, it goes like this...

An entry hole is drilled at each end, then it just plows the endmill through the middle of the slot.

I know I will have excellent tool life, but would like to get the cycle time for the roughing down from the current backplot time of 10 mins.

 

TIA for any suggestionsthumbsup.gif

Share this post


Link to post
Share on other sites

good luck Kieth, We have some Haynes 282. I treat it like Rene. And to be honest, I havent had a lot of luck with dynamic toolpaths in this stuff. Seems plowing your way thru works better.It has less of a chance to fight back

Share this post


Link to post
Share on other sites

I have used Dynamic on this stuff with good results in the past, but the amount of material to be removed was far less, and I was able to use Dynamic core as they were not closed chains. I've never seen the 282... maybe it's worse?

When your all done laughing I'd like some suggestions
good luck Kieth

 

You were suppossed to be done laughing before suggesting something!ouch.gif

LOL, thanks Wes, I'll make up a plowing program to have as backup!

Share this post


Link to post
Share on other sites

282 is new. It turns 718 Inconnel into aluminum ;)

Share this post


Link to post
Share on other sites

Hey Keith,

 

We do it all the time, with your situation I would usually go with

 

1/4 hanita varimill 2 5 flute 125 sfm .0025 fpt (chip thinning applied) .025 stepover, I usually about 120 mins in cut in haynes 188

 

or

 

3/8 hanita varimill 2 5 flute 145 sfm .0028 fpt (chip thinning applied) .0375 stepover, I usually about 60-90 mins in cut in haynes 188

 

 

HTH.

 

 

:thumbsup:

Share this post


Link to post
Share on other sites

Create an account or sign in to comment

You need to be a member in order to leave a comment

Create an account

Sign up for a new account in our community. It's easy!


Register a new account

Sign in

Already have an account? Sign in here.


Sign In Now
Sign in to follow this  
Followers 0

  • Recently Browsing   0 members

    No registered users viewing this page.

Join us!

eMastercam - your online source for all things Mastercam.

Together, we are the strongest Mastercam community on the web with over 56,000 members, and our online store offers a wide selection of training materials for all applications and skill levels.

Follow us