Remove X0 in G28

[RBTshop]

I would like the post to always default to no X0 in the G28 line for our Haas mills.

Is there a simple way to go into Mastercam X6 and do this?

 

This is what the end of my programs look like.

G91 G28 Z0. M9

G28 X0. Y0.

M30

 

This is what I would like the default to be without having to remove the X0 each time we post.

G91 G28 Z0. M9

G28 Y0.

M30

[Colin Gilchrist]

Yes, you'll need to make a small modification to your post processor. First, save a backup of your post.

 

Then, in 'pretract', look for the line with the "X0.", on it.

 

You'll need to remove the code as shown below:

 

Before:

pbld, n$, sccomp, *sm05, psub_end_mny, e$
  pbld, n$, sgabsinc, sgcode, *sg28ref, "Z0.", scoolant, e$
  if nextop$ = 1003 | tlchg_home, pbld, n$, *sg28ref, "X0.", "Y0.", protretinc, e$
  else, pbld, n$, protretinc, e$

 

After:

 

pbld, n$, sccomp, *sm05, psub_end_mny, e$
  pbld, n$, sgabsinc, sgcode, *sg28ref, "Z0.", scoolant, e$
  if nextop$ = 1003 | tlchg_home, pbld, n$, *sg28ref, "Y0.", protretinc, e$
  else, pbld, n$, protretinc, e$