Jump to content

Welcome to eMastercam

Register now to participate in the forums, access the download area, buy Mastercam training materials, post processors and more. This message will be removed once you have signed in.

Use your display name or email address to sign in:

mpmaster used in multi axis link


Recommended Posts

I am hoping there is a way to make the mpmaster post use multiaxis link. All my shop posts pretty much are modified from the mpmaster. 

At current if I post a multi axis link I get the error " ERROR- SELECT MACHINE ACHIEVABLE TOOLPLANE WITH Y - AXIS ALONG MACHINE Y - SET AND REPOST "

I am positive everything is setup correctly. I have tried the generic 4th axis post and it posts just fine. Which if it comes down to it. I will start to modify that post, using the mpmaster as a guide for setting up all of the high speed functions and such. But I am hoping there is a switch or value that may be holding back the mpmaster post from moving forward and posting. I did just download the mpmaster from emastercam for the 2018 version to make sure my post was not overly old. 

 

Link to comment
Share on other sites

Hi colin

 

the programming is correct. As stated if I use generic 4th axis post it will post the correct code for a multi axis link. I only have a problem using monastery post. I was hoping maybe momaster post is missing a parameter or setting to get it to work.

Link to comment
Share on other sites
4 hours ago, Colin Gilchrist said:

Post up a file so someone can help you. There are so many different things it could be.

Which 'Generic 4th Axis" Post did you use? Was it posting with MPFAN?

Like I said, so many different things it could be. 

Here is a basic sample.  just doing the front path, then to the right. Then posting with a modified mpmaster post. I did download a untouched mpmaster post to make sure I did not modify somehting I should not of. Still same result. 

The post I tried really fast to check it worked was Generic Fanuc 4x Mill.pst

T.mcam

Link to comment
Share on other sites
On ‎6‎/‎23‎/‎2018 at 3:08 PM, Colin Gilchrist said:

What machine are you driving? If it is Horizontal, make sure you are using the Horizontal Machine Definition, and using Top WCS / Front Tool Plane. All other rotated Tool Planes must be a "rotation of Front, around the Y+ axis".

Does this mean that the Tool Plane must be the Front Plane relative to the currently active Top WCS, or that it must be specifically the Mastercam 'Top/Front' planes ? ( which would necessitate moving the part geometry) ? Thanks

 

Link to comment
Share on other sites
3 minutes ago, pete_hull said:

Does this mean that the Tool Plane must be the Front Plane relative to the currently active Top WCS, or that it must be specifically the Mastercam 'Top/Front' planes ? ( which would necessitate moving the part geometry) ? Thanks

 

It is typical with horizontals. Top/front Top/right Top/left.

 

So I guess mpmaster is not capable of multiaxis link? 

Link to comment
Share on other sites
4 minutes ago, pete_hull said:

Does this mean that the Tool Plane must be the Front Plane relative to the currently active Top WCS, or that it must be specifically the Mastercam 'Top/Front' planes ? ( which would necessitate moving the part geometry) ? Thanks

 

You must have a "Front Plane", that is rotated relative to the current WCS. "Front Relative" is a good way to describe it. You are not required to use the "System Planes" for this to work. It is the relationship between the WCS and Tool Plane that is important...

  • Thanks 1
Link to comment
Share on other sites
1 minute ago, medaq said:

It is typical with horizontals. Top/front Top/right Top/left.

 

So I guess mpmaster is not capable of multiaxis link? 

I'll have to take a look at your file. I just haven't had time yet to do that. My guess is there is either additional logic in MPMaster, or something funky like the Axis Combination is causing the error.

Since MPMaster was originally based on the Generic Fanuc 4X Mill Post, I'd say that it is capable, but needs something to get fixed in order for it to work correctly...

Link to comment
Share on other sites
8 minutes ago, Colin Gilchrist said:

You must have a "Front Plane", that is rotated relative to the current WCS. "Front Relative" is a good way to describe it. You are not required to use the "System Planes" for this to work. It is the relationship between the WCS and Tool Plane that is important...

Thanks Colin. That is very good to know.

Link to comment
Share on other sites

I can confirm that the Multi-Axis Link is indeed broken in 2018, when programming for a Horizontal Machine, using the Top/Front programming method.

Here are some snippets of the NCI code.

First, Operation #1, showing the correct Tool Plane Matrix (1014 line):

999
1 0 1
1051
HX250IG
1053
HX250IG-1
1011
0. 0. 0. 0. 0. 0. 0. 0. 0. 0.
1012
0 0 0 0 0 0 0 0 1 0
1013
41 1. 0. 1 2 0. 0. 0. 2 C:\Users\Public\Documents\shared Mcam2018\Mill\Tools\flatmill.mcam
1014
1. 0. 0. 0. 0. 1. 0. -1. 0.
1016
1 10 1 2 0. 0. 0. 41 0 0 4 0 0. -1 1 1 4 0. 1
1017
1. 0. 0. 0. 0. 1. 0. -1. 0.
950
0 0 0 293 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0
1025
5050 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0
1027
1. 0. 0. 0. 1. 0. 0. 0. 1. 0. 0. 0.
1028
0 0 0. 0. 1. 0. 0. 1. 0 0 0 0
1029
0. 0. 0. 0. 0. 0. 0. 0. 0. 0 0
1020
0. 0. 0. 0. 0. 0. 0 0. 1. 0. 0. 0 50000 ALUMINUM inch - 2024
20010
Front
20011

20012
Front
20013

20014
Top
20015

20016
ALUMINUM inch - 2024
20017

20018
Toolpath Group-1
20019

20001
1 INCH FLAT ENDMILL
20002

20003

20004
7 10 1 0 1. 0. 0. 45. 7 7 19.864 50. 50. 2483 8 4 1. 0. 0. 0. 0. 0. 0. 0. 0 0.5 0
20006
0 0. 0. 0. 0. 0.1 0. 0. 0.
20007
0. 1. 2. 1.2 1. 2. 1. 0 0. 0. 0 2. 1.
20008
0. 0. 1. 0 0. 0. 0 0. 0.
20009
0 0
20020
Default Holder
20021

20800
0.
1001
0 100 10 7 7 7 0 2483 19.864 0 -0.46622976 0.48026214 0.1 10. 10. -10. 22 0.
0
0 -0.46622976 0.48026214 2.10591072 -2. 0
0
0 -0.46622976 0.48026214 0.1 -2. 0
1
0 -0.46622976 0.48026214 0. 50. 0
1
41 -0.46622976 0.38026214 0. 19.864 2000
3
0 0 -0.36622976 0.28026214 -0.36622976 0.38026214 0. -1. 0 0
1
0 0.82112567 0.28026214 0. -1. 1000
2
0 0 1.32112567 -0.21973786 0.82112567 -0.21973786 0. -1. 0 0
1
0 1.32112567 -1.6383963 0. -1. 0
2
0 0 0.82112567 -2.1383963 0.82112567 -1.6383963 0. -1. 0 0
1
0 -1.5535852 -2.1383963 -0. -1. 0
2
0 0 -2.0535852 -1.6383963 -1.5535852 -1.6383963 -0. -1. 0 0
1
0 -2.0535852 -0.21973786 -0. -1. 0
2
0 0 -1.5535852 0.28026214 -1.5535852 -0.21973786 0. -1. 0 0
1
0 -0.36622976 0.28026214 0. -1. 100
3
0 0 -0.26622976 0.38026214 -0.36622976 0.38026214 0. -1. 0 0
1
140 -0.26622976 0.48026214 0. -1. 200
1004

In that bit of code, you can see that the 1014 Matrix is correct, and shows "Front" (1,0,0     0,0,1    0,-1,0). The 20010 String also identifies "Front" as the plane.

Here is the section where the Link Motion takes place:

0
0 -0.26622976 0.48026214 2.10591072 -2. 0
999
1 0 2
1011
0. 0. 0. 0. 0. 0. 0. 0. 0. 0.
1012
0 0 0 0 0 0 0 0 0 0
1013
41 1. 0. 1 1 0. 0. 0. 2 C:\Users\Public\Documents\shared Mcam2018\Mill\Tools\flatmill.mcam
1014
1. 0. 0. 0. 1. 0. 0. 0. 1.
1016
2 10 154 1 0. 0. 0. 41 1 0 4 0 0. -1 1 1 4 0. 2
1017
1. 0. 0. 0. 1. 0. 0. 0. 1.
950
0 0 0 293 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0
1025
5050 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0 0
1027
1. 0. 0. 0. 1. 0. 0. 0. 1. 0. 0. 0.
1028
0 0 0. 0. 1. 0. 0. 1. 0 0 0 0
1029
0. 0. 0. 0. 0. 0. 0. 0. 0. 0 0
1020
0. 0. 0. 0. 0. 0. 0 0. 1. 0. 0. 0 50000 ALUMINUM inch - 2024
20010
Front
20011

20012
Front
20013

20014
Top
20015

20016
ALUMINUM inch - 2024
20017

20018
Toolpath Group-1
20019

20800
0.
1000
0 100 10 7 7 7 0 2483 19.864 0 -0.17426049 -2.09817596 0.465628 10. 10. -10. 22 0.
11
-0.17426049 -2.09817596 0.465628 -0.13928892 -3.09756427 0.465628 1000. 62 0 0.11016555 -0.99391325 0. 10. -10. 0.
11
-0.08282975 -2.08558263 0.45099385 -0.01199286 -3.08307054 0.45099385 -1. 62 0 0.16263497 -0.98668631 0. 10. -10. 0.
11
0.00780598 -2.06816605 0.4363597 0.11529266 -3.06237257 0.4363597 -1. 62 0 0.21464817 -0.97669144 0. 10. -10. 0.
11
0.09739244 -2.04597507 0.42172556 0.24218544 -3.03543704 0.42172556 -1. 62 0 0.26605922 -0.96395669 0. 10. -10. 0.
11
0.18567831 -2.01907196 0.40709141 0.36828865 -3.00225733 0.40709141 -1. 62 0 0.31672389 -0.94851778 0. 10. -10. 0.
11
0.27241593 -1.98753218 0.39245727 0.49319327 -2.96285642 0.39245727 -1. 62 0 0.36650008 -0.93041802 0. 10. -10. 0.
11
0.35736198 -1.95144421 0.37782312 0.61648152 -2.91728947 0.37782312 -1. 62 0 0.41524813 -0.90970819 0. 10. -10. 0.
11
0.44027816 -1.91090928 0.36318897 0.73773087 -2.86564583 0.36318897 -1. 62 0 0.4628313 -0.88644638 0. 10. -10. 0.
11
0.52093187 -1.86604111 0.34855483 0.85651871 -2.80805039 0.34855483 -1. 62 0 0.5091161 -0.86069785 0. 10. -10. 0.
11
0.59909685 -1.81696557 0.33392068 0.97242748 -2.74466392 0.33392068 -1. 62 0 0.5539727 -0.83253484 0. 10. -10. 0.
11
0.67455382 -1.76382032 0.31928653 1.08504999 -2.67568265 0.31928653 -1. 62 0 0.59727525 -0.80203633 0. 10. -10. 0.
11
0.74709112 -1.70675446 0.30465239 1.19399461 -2.60133663 0.30465239 -1. 62 0 0.63890228 -0.7692879 0. 10. -10. 0.
11
0.81650526 -1.64592806 0.29001824 1.29889027 -2.52188736 0.29001824 -1. 62 0 0.67873702 -0.73438141 0. 10. -10. 0.
11
0.8826015 -1.58151176 0.27538409 1.39939076 -2.43762441 0.27538409 -1. 62 0 0.71666772 -0.69741478 0. 10. -10. 0.
11
0.94519443 -1.51368627 0.26074995 1.49517832 -2.34886153 0.26074995 -1. 62 0 0.75258798 -0.65849172 0. 10. -10. 0.
11
1.00410847 -1.44264185 0.2461158 1.58596637 -2.25593232 0.2461158 -1. 62 0 0.78639702 -0.6177214 0. 10. -10. 0.
11
1.05917834 -1.36857781 0.23148166 1.67150122 -2.1591856 0.23148166 -1. 62 0 0.818 -0.57521822 0. 10. -10. 0.
11
1.11024955 -1.29170191 0.21684751 1.75156285 -2.05898103 0.21684751 -1. 62 0 0.84730828 -0.53110139 0. 10. -10. 0.
11
1.15717884 -1.21222981 0.20221336 1.82596487 -1.95568475 0.20221336 -1. 62 0 0.87423962 -0.48549467 0. 10. -10. 0.
11
1.19983456 -1.13038445 0.18757922 1.89455367 -1.84966559 0.18757922 -1. 62 0 0.89871849 -0.43852602 0. 10. -10. 0.
11
1.23809705 -1.04639543 0.17294507 1.95737819 -1.74111454 0.17294507 -1. 62 0 0.92067622 -0.39032718 0. 10. -10. 0.
11
1.27185896 -0.96049837 0.15831092 2.01531391 -1.62928439 0.15831092 -1. 62 0 0.94005119 -0.34103337 0. 10. -10. 0.
11
1.3010256 -0.87293422 0.14367678 2.06830473 -1.51424752 0.14367678 -1. 62 0 0.95678907 -0.29078286 0. 10. -10. 0.
11
1.32551514 -0.78394863 0.12904263 2.11612294 -1.39627151 0.12904263 -1. 62 0 0.9708429 -0.23971664 0. 10. -10. 0.
11
1.34525887 -0.69379122 0.11440848 2.15854934 -1.27564912 0.11440848 -1. 62 0 0.98217325 -0.18797794 0. 10. -10. 0.
11
1.36020142 -0.60271492 0.09977434 2.19537669 -1.1526988 0.09977434 -1. 62 0 0.99074834 -0.13571191 0. 10. -10. 0.
11
1.37030086 -0.51097521 0.08514019 2.22641351 -1.02776447 0.08514019 -1. 62 0 0.99654412 -0.08306518 0. 10. -10. 0.
11
1.37552887 -0.41882945 0.07050605 2.25148817 -0.90121447 0.07050605 -1. 62 0 0.99954432 -0.03018542 0. 10. -10. 0.
11
1.37587077 -0.32653614 0.0558719 2.27045295 -0.77343962 0.0558719 -1. 62 0 0.99974052 0.02277901 0. 10. -10. 0.
11
1.37132561 -0.23435417 0.04123775 2.28318794 -0.64485034 0.04123775 -1. 62 0 0.99713219 0.07567954 0. 10. -10. 0.
11
1.36190614 -0.14254216 0.02660361 2.2896045 -0.5158728 0.02660361 -1. 62 0 0.99172663 0.12836777 0. 10. -10. 0.
11
1.34763879 -0.05135764 0.01196946 2.28964806 -0.38694449 0.01196946 -1. 62 0 0.98353901 0.1806959 0. 10. -10. 0.
11
1.32856357 0.03894357 -0.00266469 2.28330012 -0.25850914 -0.00266469 -1. 62 0 0.9725923 0.23251712 0. 10. -10. 0.
11
1.30473399 0.12810816 -0.01729883 2.27057925 -0.13101138 -0.01729883 -1. 62 0 0.95891721 0.28368607 0. 10. -10. 0.
11
1.27621692 0.215886 -0.03193298 2.25154116 -0.00489134 -0.03193298 -1. 62 0 0.94255209 0.3340592 0. 10. -10. 0.
11
1.24309234 0.30203085 -0.04656712 2.2262777 0.11942051 -0.04656712 -1. 62 0 0.92354286 0.38349521 0. 10. -10. 0.
11
1.20545317 0.38630104 -0.06120127 2.19491514 0.24150804 -0.06120127 -1. 62 0 0.90194285 0.43185541 0. 10. -10. 0.
11
1.16340501 0.46846019 -0.07583542 2.15761154 0.36097351 -0.07583542 -1. 62 0 0.87781264 0.47900414 0. 10. -10. 0.
11
1.11706581 0.5482778 -0.09046956 2.11455373 0.47744092 -0.09046956 -1. 62 0 0.85121993 0.52480913 0. 10. -10. 0.
11
1.06656557 0.62552998 -0.10510371 2.06595388 0.59055841 -0.10510371 -1. 62 0 0.82223932 0.5691419 0. 10. -10. 0.
11
1.01204595 0.7 -0.11973786 2.01204595 0.7 -0.11973786 -1. 62 0 0.79095211 0.61187806 0. 10. -10. 0.
999
1 0 3

This is where the error is coming from.

That motion is posting with the "Top" Plane active. Even though the 20010 lines says "Front", the Matrix on the 1014 line shows 1,0,0   0,1,0   0,0,1 (Top).

This is causing not only the "error message" to be displayed, it is also screwing up the internal "angle" calculations inside the Post.

Just because you are "not getting an error message" when you Post with the Generic Fanuc 4X Mill Post, does not mean the output is correct! >>>>>>> It isn't!

Here is the whole program, posted out with the Generic Haas 4X Mill Post:

%
O0
(T)
(DATE=DD-MM-YY - 27-06-18 TIME=HH:MM - 22:24)
(MCX FILE - D:\EMASTERCAM\MEDAQ\T.MCAM)
(NC FILE - C:\USERS\COLIN_000\DOCUMENTS\MY MCAM2018\MILL\NC\T.NC)
(MATERIAL - ALUMINUM INCH - 2024)
(T7|1 INCH FLAT ENDMILL|H7|D7|TOOL DIA. - 1.|WEAR COMP)
G20
G0 G17 G40 G49 G80 G90
/ G91 G28 Z0.
/ G28 X0. Y0.
/ G92 X10. Y10. Z-10.
(HX250IG)
(HX250IG-1)
T7 M6
G0 G90 X-.4662 Y.4803 B0. S2483 M3
G43 H7 Z2.1059
M8
Z.1
G1 Z0. F50.
G41 D7 Y.3803 F19.9
G3 X-.3662 Y.2803 I.1 J0.
G1 X.8211
G2 X1.3211 Y-.2197 I0. J-.5
G1 Y-1.6384
G2 X.8211 Y-2.1384 I-.5 J0.
G1 X-1.5536
G2 X-2.0536 Y-1.6384 I0. J.5
G1 Y-.2197
G2 X-1.5536 Y.2803 I.5 J0.
G1 X-.3662
G3 X-.2662 Y.3803 I0. J.1
G1 G40 Y.4803
G0 Z2.1059
G1 X.4803 Y-2.1088 Z.3662 B-180. F8200.
Y-2.1059 Z.4662 F500.
G0 B0.
X-.4662 Y.4803 Z2.1059
Z.1
G1 Z0. F50.
G41 D7 Y.3803 F19.9
G3 X-.3662 Y.2803 I.1 J0.
G1 X.8211
G2 X1.3211 Y-.2197 I0. J-.5
G1 Y-1.6384
G2 X.8211 Y-2.1384 I-.5 J0.
G1 X-1.5536
G2 X-2.0536 Y-1.6384 I0. J.5
G1 Y-.2197
G2 X-1.5536 Y.2803 I.5 J0.
G1 X-.3662
G3 X-.2662 Y.3803 I0. J.1
G1 G40 Y.4803
G0 Z2.1059

*** THIS IS THE "LINKING" SECTION. NOTICE THE MISSING "B" ADDRESSES???   ***

G1 X-.4656 Y-2.0982 Z-.1743 F500.
X-.451 Y-2.0856 Z-.0828
X-.4364 Y-2.0682 Z.0078
X-.4217 Y-2.046 Z.0974
X-.4071 Y-2.0191 Z.1857
X-.3925 Y-1.9875 Z.2724
X-.3778 Y-1.9514 Z.3574
X-.3632 Y-1.9109 Z.4403
X-.3486 Y-1.866 Z.5209
X-.3339 Y-1.817 Z.5991
X-.3193 Y-1.7638 Z.6746
X-.3047 Y-1.7068 Z.7471
X-.29 Y-1.6459 Z.8165
X-.2754 Y-1.5815 Z.8826
X-.2607 Y-1.5137 Z.9452
X-.2461 Y-1.4426 Z1.0041
X-.2315 Y-1.3686 Z1.0592
X-.2168 Y-1.2917 Z1.1102
X-.2022 Y-1.2122 Z1.1572
X-.1876 Y-1.1304 Z1.1998
X-.1729 Y-1.0464 Z1.2381
X-.1583 Y-.9605 Z1.2719
X-.1437 Y-.8729 Z1.301
X-.129 Y-.7839 Z1.3255
X-.1144 Y-.6938 Z1.3453
X-.0998 Y-.6027 Z1.3602
X-.0851 Y-.511 Z1.3703
X-.0705 Y-.4188 Z1.3755
X-.0559 Y-.3265 Z1.3759
X-.0412 Y-.2344 Z1.3713
X-.0266 Y-.1425 Z1.3619
X-.012 Y-.0514 Z1.3476
X.0027 Y.0389 Z1.3286
X.0173 Y.1281 Z1.3047
X.0319 Y.2159 Z1.2762
X.0466 Y.302 Z1.2431
X.0612 Y.3863 Z1.2055
X.0758 Y.4685 Z1.1634
X.0905 Y.5483 Z1.1171
X.1051 Y.6255 Z1.0666
X.1197 Y.7 Z1.012

*** END OF LINKING MOTION ***

G0 B90.
X.7 Y-.1197
Z.1
G1 Z0. F50.
G41 D7 X.6 F19.9
G3 X.5 Y-.2197 I0. J-.1
G1 Y-1.6384
G2 X-.5 I-.5 J0.
G1 Y-.2197
G2 X.5 I.5 J0.
G3 X.6 Y-.3197 I.1 J0.
G1 G40 X.7
G0 Z1.012
M09
M5
G91 G28 Z0.
G28 X0. Y0. B0.
M30
%

 

I hate to be the bearer of bad news, but at least you know it isn't just a problem with MPMaster. This simply doesn't work for a Horizontal machine, programmed with Top/Front, in Mastercam 2018...

 

  • Thanks 1
  • Like 1
Link to comment
Share on other sites

And for those playing along at home, because of the bad 1014 matrix definition, here is the offending Post Block where the error is being generated:

pcuttype   #Determine the cut type
      #cuttype (0 = Tool Plane, 1 = Axis Subs,  2 = Polar, 3 = 4/5 axis)
      cuttype = rotary_type$
      if cuttype = three, cuttype = zero
      if mill5$,
        [
        if rot_on_x = zero, result = mprint(saxisoff)
        cuttype = three
        ]
      if vmc & m1$ <> 1 & rot_on_x = 1, #if rotary about the X axis and plane X isn't the same direction as machine X
        [
        result = mprint(sxaxiswarn,2)
        if result = 2, exitpost$
        ]
      if vmc & m5$ <> 1 & rot_on_x = 2, #if rotary about the Y axis and plane Y isn't the same direction as machine Y
        [
        result = mprint(syaxiswarn,2)
        if result = 2, exitpost$
        ]
      if not(vmc) & m6$ <> 1, #if rotary about the Y axis and plane Y isn't the same direction as machine Y
        [
        result = mprint(szaxiswarn,2)
        if result = 2, exitpost$
        ]
      if rot_type <> 1, use_rotmcode = 0                 #Use indexing M code only for signed direction.        
      #Check for Tool Origin in Polar Milling
      if cuttype = two & (tox$ | toy$ | toz$), result = mprint(stlorgerr)
      #Transform Rotate, set mr_rt_actv if user selected 'coordinates' 
      if sub_trnstyp$ = one & sub_trnmthd$ = two,
        [
        #Calculate the rotation incremental angle for G68
        rt_csav = atan2(sub_m2$, sub_m1$)
        rt_cinc = prv_rt_csav - rt_csav
        while rt_cinc > 180, rt_cinc = rt_cinc - 360
        while rt_cinc < -180, rt_cinc = rt_cinc + 360
        if not(rot_cw_pos), rt_cinc = -rt_cinc
        !rt_csav
        if sub_sec_no$, mr_rt_actv = two
        else, mr_rt_actv = one
        ]
      else, mr_rt_actv = zero
      pfcalc_u_min
      pmotion_su

 

Specifically, it is this error trap that is catching the problem:

      if not(vmc) & m6$ <> 1, #if rotary about the Y axis and plane Y isn't the same direction as machine Y
        [
        result = mprint(szaxiswarn,2)
        if result = 2, exitpost$
        ]

 

In your sample, "vmc" is set to "0" (to indicate a horizontal). The "Y" Axis should be "vertical" relative to the "World", which means the value of 'm6$' should be equal to '1'. With the Link operation outputting the incorrect Tool Plane Matrix, the output is just wrong. This needs to be reported to CNC Software. I did notice they actually mentioned that Multi-Axis Link was broken in 2018.

I have not had a chance yet to test this in 2019...

 

 

 

  • Thanks 1
Link to comment
Share on other sites
10 minutes ago, Colin Gilchrist said:

I'm with Ron on this one. It is so easy to build an 'Arc' in the Top plane, at the correct "Z" retract distance, and drive a Curve 5X path to handle the B rotation. (Using Top/Front). This gives you the linking moves that will Post and Backlot correctly. 

I will sometimes use a Helix or a 3 Point curve or I will make a Safety Cylinder and then project a line from the end of one toolpath to the beginning of another and then use it. Many ways to link your toolpaths like we have done for many years. Multiaxis will get better and all this extra work will not be needed. When they finally tie Kinematics to the process that is when all these issues will go away.

  • Like 1
Link to comment
Share on other sites
35 minutes ago, C^Millman said:

I will sometimes use a Helix or a 3 Point curve or I will make a Safety Cylinder and then project a line from the end of one toolpath to the beginning of another and then use it. Many ways to link your toolpaths like we have done for many years. Multiaxis will get better and all this extra work will not be needed. When they finally tie Kinematics to the process that is when all these issues will go away.

Amen, hallelujah!

Link to comment
Share on other sites

Colin

 

Thank you for going over it and making sure it was not just mpmaster, I appreciate that a lot. Saves me a ton of time trying to make it work with other posts to find out it would of not work or just dangerous. 

 

I wish I had the curve 5 axis. Being we are production shop a lot of the times going against the chinese. Any easy spots to cut cycle time just makes sense for us, Hence revisiting the multiaxis link. I hope one of the mastercam guys reads this post to give it a look over to hopefully get it figured out in 2019. I personally have been holding off on 2019 with reading all the little issues that has been happening. And waiting for a proper service pack to fix all the little issues and make sure it is stable. 

 

  • Thanks 1
Link to comment
Share on other sites

Join the conversation

You can post now and register later. If you have an account, sign in now to post with your account.

Guest
Reply to this topic...

×   Pasted as rich text.   Paste as plain text instead

  Only 75 emoji are allowed.

×   Your link has been automatically embedded.   Display as a link instead

×   Your previous content has been restored.   Clear editor

×   You cannot paste images directly. Upload or insert images from URL.

 Share

  • Recently Browsing   0 members

    • No registered users viewing this page.

Join us!

eMastercam - your online source for all things Mastercam.

Together, we are the strongest Mastercam community on the web with over 56,000 members, and our online store offers a wide selection of training materials for all applications and skill levels.

Follow us

×
×
  • Create New...