drill cycle posting

[Zbuilder]

First, can anyone explain this debug info to me? I can figure out that the posted line was performed by the module printed at the beginning of the debug ivo but can't figure out what the other stuff means. Here's an example...

O0010(JUNK) pheader$ pheader$ 68.

M6 T7 ( #10-32 TAP ) psof$ ptoolcomment 70.

G90 G56 psof$ psof$ 70.

G0 X.113 Y1.0875 M3 S960 psof$ psof$ 70.

G43 H7 Z0. psof$ psof$ 70.

M98 P15 psof$ p__56:1666 70.

( CUSTOMIZABLE DRILL CYCLE - NOT CONFIGURED - NEXT HOLE ) pdrlcst_2$ p__43:1457 76.

Y-1.0865 F30. pdrlcst_2$ pdrill_2$ 76.

M98 P15 pdrlcst_2$ p__56:1666 76.

G80 pcanceldc$ pcanceldc$ 78.

M98 P15 pcanceldc$ p__56:1666 78.

M5 peof$ p__11:932 80.

G49 G53 Z0. peof$ p__11:932 80.

G53 Y0. peof$ p__11:932 80.

M6 T7 peof$ peof$ 80.

M0 peof$ peof$ 80.

M99 peof$ peof$ 80.

peof$ peof$ 80.

% peof$ peof$ 80.

 

 

I'm trying to use drill cycle #9 (which starts the custom drill cycle area drop down list, 9th position) to not output any drill cycle but only to position X & Y but I can't get the post to go to the module I copied & pasted as a new name.

[Zbuilder]

OK, I figured out why my customized postblocks were not being called & now it works but is there any way to not make it post the G80 when using drill cycle #9?

[Roger Martin from CNC Software]

ZBuilder,

 

"...ss there any way to not make it post the G80 when using drill cycle #9?:

 

I assume you're referring to this ->

 

G80 pcanceldc$ pcanceldc$ 78

 

If so...

 

Find the postline in the pcanceldc$ that outputs the 'G80' and add a conditional statement that determines whether that postline gets executed, or not...

 

I think you need to check for '9', but it is very easy to determine if this is correct (or not).

Just add a temporary "print me" line in the pcanceldc$ postblock, like shown below.

Post your custom drill toolpath and whatever

"drillcyc$ = #" is in your NC output is the value you need to check for.

 

Something like ->

code:

---

pcanceldc$

"drillcyc$ = ", ~drillcyc$, e$ # TEMP!!!

if (drillcyc$ <> 9),

pcan1, pbld, n$, "G80", strcantext, e$

---

[Zbuilder]

Cool, got it. It works. Thanks

What I don't understand is how it logically processes the postblocks. If it branches out, Does it come back to continue? If not, how does it know where to go next?

[Roger Martin from CNC Software]

"If it branches out, Does it come back to continue?"

 

If by "branch out" you mean calling another postblock, yes it comes back and picks up where it left off. You can think of a postblock as a "subroutine".

[Zbuilder]

ok. Understand now.

Is there a way to "goto" another postblock so it just goes somewhere else & not come back?

[Roger Martin from CNC Software]

"Is there a way to "goto" another postblock so it just goes somewhere else & not come back?"

 

While it is possible, I'm not telling how - 'cause you don't want to do it, as it makes Post debugging waaaay to painful.

Use conditional (logic) branching to determine what executes within a postblock and let the natural postblock flow happen.

[Zbuilder]

Ok, thanks.