pheader

[GeneD]

Is there any way to post the "Machine Group" name in the pheader?

For instance, I am renaming machine group-1 to Op10 and would like this to post at the begining of the program

[Mr. Wizzard]

pheader$ #Call before start of file

hour = int(time$)

min = int((time$ - hour)* 100)

if hour > 12, hour = hour - 12

if hour = 0, hour = 12

year$ = year$ + 2000

 

"%", e$

spaces$=0

*progno$, " ", scomm_str, sprogname$, scomm_end, e$

spathnc$ = ucase(spathnc$)

smcname$ = ucase(smcname$)

comment$ # File descriptor

spaces$=0

 

Try adding the comment$ line.

[K2csq7]

Hi Gene,

 

Welcome to the forum.

 

Here is how it's done...always back up post first!!!!!!!!!!!!!!

 

Go to the section of your post labeled "String Definitions" or something like that

and add this line

smgrp  : ""

 

Then go to the pheader postblock (or where ever you want the output to be) and add

these two lines

 	rd_cd$
 	pbld,  "( ", smgrp, " )", e$

 

Then find the pmachineinfo postblock and add this line

 	if prmcode$ = 19990, smgrp = sparameter$

[Ed Partlow Jr. from CNC Software]

Gene,

 

An alternative to making post edits, would be to configure your control definition.

 

1. Open the Control Definition Manager found on the "settings" drop down menu.

2. Go to the "NC Output --> General" Tab.

3. Select "Output group name to NC".

4. Save your control definition.

5. Reload your Machine definition.

 

If this does not output the Machine group name in your NC code, make sure the "comment$" line is present in your post as explained by Mr Wizard above.

 

- Ed

[GeneD]

Thanks for the replies.

I'm getting it close to what I'm looking for with your suggestions.

I'll experiment with it for the next few days and let you know how it worked

Thanks again

Gene

[Mr. Wizzard]

That's how it worked for me. I have mine named and when I #comment out that line, it doesn't post out. Turn it back on and it does, but yeah you have to have it checked in the CD

[Mr. Wizzard]

Keith, how'd you find out which parameter code it was so you could use a string instead?

[K2csq7]

-Start

-All Programs

-Mastercam X5 (I have X5 but I think you should have it with X4 as well)

-Documentation

-Mastercam X5 NCI Parameter Reference Guide

 

That Guide along with this Forum... Like having the developers of Mastercam sharing my office with me!!!!!!!!!!!!

[Mr. Wizzard]

Like having the developers of Mastercam sharing my office with me!!!!!!!!!!!!

 

That's so not fair

[K2csq7]

That's so not fair

 

You should have the documentation...

[Mr. Wizzard]

I have the documentation, yes.

 

A translator to explain what the computer nerd language actually means, no.

[K2csq7]

A translator to explain

 

I use this, your gonna love it!!!!!!!!!!!!

computer nerd language translator

[Mr. Wizzard]

ha, ha, nice