GO INSTEAD OF G01 ON MULTI AXIS DEBURR PATHS

[medaq]

Not sure why it is only multi axis paths, but for example on a multi axis deburr path. It will position in G01 at a high feed rate, and carry this high feed rate up till the path. Which when proofing a program, and the machine moves at a high rate towards your pallet when you thought the rapid was at 10%. Well, quite frankly, will make you pucker.  This is a modified mpmaster post. Is there somewhere to change this behavior?

 

T49 M06 (0.125 SPHERICAL / BALL-NOSED ENDMILL)
M22 (UNLOCK)
G01 G17 G90 G56 G94 B270. X-1.1144 Y-1.7801 S10000 M03 F3811.51
G43 H49 Z1.8603 T46

[Jake L]

In MC 2023 in the multiaxis deburr toolpath Parameters > Feed Rate Control > Raplace Rapid with Feed is a check box with an option to input a custom feed rate. If that box is checked then this is the code output:

N100 G20
N110 G94 G1 G17 G40 G49 G80 G90 F399.
N120 T1 M6
N130 G94 G1 G90 G54 X3.5249 Y1. A0. S1000 M3 F399. (G1 on this line due to "replace rapid with feed" box being checked)
N140 G43 H1 Z1.45 M8
N150 Z2.4916 F399.
N160 Z2.0916
N170 Z1.6916 F25.
N180 X3.5239 Z1.6434 F5.

 

If the box is unchecked:

N100 G20
N110 G0 G17 G40 G49 G80 G90
N120 T1 M6
N130 G0 G90 G54 X3.5249 Y1. A0. S1000 M3 (G0 on this line because "replace rapid with feed" box is unchecked)
N140 G43 H1 Z1.45 M8
N150 Z2.4916
N160 Z2.0916
N170 G1 Z1.6916 F25.
N180 X3.5239 Z1.6434 F5.

 

This behavior and check box location is slightly different in previous MC versions. If you're using an earlier MC version let me know and I can point you in the right direction. I believe there are similar check boxes in most of the multi axis toolpaths, which is why you may be seeing this behavior with other toolpaths.

[medaq]

3 hours ago, Jake L said:

In MC 2023 in the multiaxis deburr toolpath Parameters > Feed Rate Control > Raplace Rapid with Feed is a check box with an option to input a custom feed rate. If that box is checked then this is the code output:

N100 G20
N110 G94 G1 G17 G40 G49 G80 G90 F399.
N120 T1 M6
N130 G94 G1 G90 G54 X3.5249 Y1. A0. S1000 M3 F399. (G1 on this line due to "replace rapid with feed" box being checked)
N140 G43 H1 Z1.45 M8
N150 Z2.4916 F399.
N160 Z2.0916
N170 Z1.6916 F25.
N180 X3.5239 Z1.6434 F5.

 

If the box is unchecked:

N100 G20
N110 G0 G17 G40 G49 G80 G90
N120 T1 M6
N130 G0 G90 G54 X3.5249 Y1. A0. S1000 M3 (G0 on this line because "replace rapid with feed" box is unchecked)
N140 G43 H1 Z1.45 M8
N150 Z2.4916
N160 Z2.0916
N170 G1 Z1.6916 F25.
N180 X3.5239 Z1.6434 F5.

 

This behavior and check box location is slightly different in previous MC versions. If you're using an earlier MC version let me know and I can point you in the right direction. I believe there are similar check boxes in most of the multi axis toolpaths, which is why you may be seeing this behavior with other toolpaths.

 

 

That makes sense why I am getting this behavior, just did not realize this option was effecting the start position.  I did go check, and yes this is changing the g01 and g00 at the start of the path.  I thought this option was just for connecting the paths inside the tool path, since I am clicking it under the clearance blend spline option in linking. I did find another way around it, and placed a point tool path to position the tool first in g00. Then the tool path will continue with the feed rate as originally set.