Change axis order in post

[Nils N]

I need to change my Z output from this

 

N130 G1 Z26. F20.

N132 G3 Y58.6986 I0. J.1875 F100.

N134 Z25.875 I0. J-.375

N136 Z25.75 I0. J-.375

N138 Z25.625 I0. J-.375

N140 Z25.5 I0. J-.375

N142 Z25.375 I0. J-.375

N144 Z25.25 I0. J-.375

N146 Z25.125 I0. J-.375

 

to this

 

N130 G1 Z26. F20.

N132 G3 Y58.6986 I0. J.1875 F100.

N134 G3 I0. J-.375 Z25.875

N136 I0. J-.375 Z25.75

N138 I0. J-.375 Z25.625

N140 I0. J-.375 Z25.5

N142 I0. J-.375 Z25.375

N144 I0. J-.375 Z25.25

N146 I0. J-.375 Z25.125

 

So the the Z is posted after the I J values. Where do I find this in the post?

 

Nils

[Superman]

Nils,

copy the original first

 

Find (# Motion NC output) Section

pcirout #Output to NC of circular interpolation

pcan1, pbld, n$, `sgfeed, sgplane, sgcode, sgabsinc,

pxout, pyout, pzout, pcout, parc, feed, strcantext, scoolant, e$ #pccdia removed

 

Change to

pcirout #Output to NC of circular interpolation

pcan1, pbld, n$, `sgfeed, sgplane, sgcode, sgabsinc,

pxout, pyout, parc, pzout, pcout, feed, strcantext, scoolant, e$ #pccdia removed

[Nils N]

Superman thanks, I'm working on changing the post I'll be a bit got get some other work done first I'll let you know how it goes

[Nils N]

Superman that work for the Z placement

my post looked like this

 

pcirout #Output to NC of circular interpolation

sav_gcode = gcode$

parc_setup

pcan1, pbld, n$, `sgfeed, `sgcode, sgplane, sgabsinc, pccdia,

xout, yout, zout, s_out, p_out, parcijk,`feed, strctxt, scoolant, e$

gcode$ = sav_gcode

if nc_lout$ <> m_one & feed = zero, psfeederror

 

and I changed to this

 

pcirout #Output to NC of circular interpolation

sav_gcode = gcode$

parc_setup

pcan1, pbld, n$, `sgfeed, `sgcode, sgplane, sgabsinc, pccdia,

xout, yout, parcijk, zout, s_out, p_out,`feed, strctxt, scoolant, e$

gcode$ = sav_gcode

if nc_lout$ <> m_one & feed = zero, psfeederror

 

now I need to get a G3 in the beginning of the move as shown below

From this

 

N130 G1 Z26. F20.

N132 G3 Y58.6986 I0. J.1875 F100.

N134 I0. J-.375 Z25.875

N136 I0. J-.375 Z25.75

 

To this

 

N130 G1 Z26. F20.

N132 G3 Y58.6986 I0. J.1875 F100.

N134 G3 I0. J-.375 Z25.875

N136 I0. J-.375 Z25.75

N138 I0. J-.375 Z25.625

 

I appreciate your help

[Superman]

Nils,

 

I assume you are wanting G2/G3 to be output on all arc lines

 

If yes,

In this "pcirout" area use a "*" to force the output unconditionally, without the *, the code and value is only output if different from the previous block

 

so

*sgcode instead of sgcode

[Nils N]

Superman,

 

I added the change to the code and it posts out like it should but the controller won't take it.

I sent an email to ***or to find out what the post needs.

 

I'll let you know what I get.

 

You've been great with the help.

 

Nils