X5 axis substitution

[Jason Parks from Barefoot CNC]

Hey Guys has anyone had problems with axis sub in X5. I have a part that i am trying to drill holes on a dia with axis sub but not working in X5 but perfect in X4. All the settings are the same.

[CJep]

Jason, are you using drill multi axis?

[Jason Parks from Barefoot CNC]

no just flat geometry. using axis sub to roll onto a dia.

[CJep]

Jason, instead of having the points laid out flat try using the geom as it is on the part. For instance I have a sample file with 8 points radially located around a 2" dia. If I window select all the points and turn off filter out the duplicates. Set the link params so that the TOS is the radius of the part, set the depth as an inc value or abs by subtracting the depth from the radius. In the rotary axis control set the rotation type to rotary positioning.

 

This is the code as output with Gen Haas in McamX5.

 

N100 G20

N110 G0 G17 G40 G49 G80 G90

N120 T1 M6

N130 G0 G90 G54 X1.5 Y0. A90. S1850 M3

N140 G43 H1 Z1.25

N150 G99 G81 Z.75 R1.25 F18.5

N160 A45.

N170 A0.

N180 A-45.

N190 A-90.

N200 A-135.

N210 A-180.

N220 A-225.

N230 G80

N240 M5

N250 G91 G28 Z0.

N260 G28 X0. Y0. A0.

N270 M30

[Steve Hattori]

I was told that there is a problem with 4 axis rotary in X5, but the work-around was to use axis substitution...? It worked with a milling op, but haven't tried drilling. I usually use drill5x or FBM.

[Jason Parks from Barefoot CNC]

figured it out. axis sub does work. By default the unroll check box is checked and i did not catch it. I had my thank God it's friday moment. Thanks guys for your help!!!!!!!