Post question again

[mikhael gutman]

Hi !

I would like to use “STOCK TO LEAVE” value for setting up mode for high speed machining automatically in G-code . So idea is : pull out stock value ,compare with limits of stock and in depend of this limits and my “stock to leave “ value get spatial codes in my g-code generated by post.

I would be really appreciate any help to get stock to leave value in G-code which from ver . 8 came as new option but I newer see it working.

 

Thank you in advance

[Ying Jiang]

Have you tried Mpmaster post from this site?

 

Download from here: http://www.emastercam.com/posts/mpmaster/index.html

[mikhael gutman]

Hi Ying!

Thank you for reply.

Yes by this mpmaster i can get stock value for surface machining , but what about contour or pocket machining ?

Regards

 

[ 05-16-2003, 12:21 AM: Message edited by: mikhael gutman ]

[Rekd™]

If I recall, this has been covered. It goes something like this, (being lazy like you and not checking the search feature), there's no varialbles for those available to the end user.

 

'Rekd teh So many un-used tools in the shed..

 

[ 05-16-2003, 10:15 AM: Message edited by: Rekd ]

[Allan Brown]

http://www.emastercam.com/cgi-bin/ultimate...ic;f=1;t=006030

[Ying Jiang]

mikhael:

 

There is a will, there is a way

 

Please read Dave's reply , for Contour or pocket tool path, you need to add/modify the following in the post (I just tried with Mpmaster post for v9 and it works fine):

......

# ------------------------------------------------------------------------

# Parameter Tables

# ------------------------------------------------------------------------

fprmtbl 2 2 # 2D Contour

10010 stock2dxy # Amount of stock to leave on X & Y

10068 stock2dz # Amount of stock to leave on Z

 

fprmtbl 4 2 # 2D Pocket

10010 stock2dxy # Amount of stock to leave on X & Y

10068 stock2dz # Amount of stock to leave on Z

 

......

 

fmt 2 stock2dxy # Amoutn of Stock left on X & Y

fmt 2 stock2dz # Amoutn of Stock left on Z

 

......

 

pstock # Comment amount of stock to leave

spaces=0

if opcode = 2 | opcode = 4,

[

pbld, n, pspc, "(TOOLPATH - ", *stoper, ")", e

pbld, n, pspc, "(STOCK LEFT ON X & Y = ", *stock2dxy, ")", e

pbld, n, pspc, "(STOCK LEFT ON Z = ", *stock2dz, ")", e

]

......

pparameter # Run parameter table

if opcode=2 | opcode=4 | opcode=13 | opcode=14, result = fprm (opcode)

......

 

Here is the output I get with the modified post:

 

......

N10 G00 G17 G20 G40 G49 G80 G90

N20 (CONTOUR)

N30 T3 M06 ( 3/4 FLAT ENDMILL)

N40 (MAX - Z2.)

N50 (MIN - Z-.095)

N60 (TOOLPATH - CONTOUR)

N70 (STOCK LEFT ON X & Y = .012)

N80 (STOCK LEFT ON Z = .005)

N90 G00 G90 G54 X.45 Y-1.412 S713 M03

N100 G43 H3 Z2. M08

N110 Z.1

N120 G01 Z-.095 F6.42

......

N300 (POCKET)

N310 T2 M06 ( 1/2 BALL ENDMILL)

N320 (MAX - Z2.5)

N330 (MIN - Z-.49)

N340 (TOOLPATH - POCKET)

N350 (STOCK LEFT ON X & Y = .015)

N360 (STOCK LEFT ON Z = .01)

N370 G00 G90 G54 X-.3671 Y-.0415 S1069 M03

N380 G43 H2 Z2. M08

N390 Z.1

N400 G01 X-.625 Z.0865 F6.42

......

 

HTH.

[Rekd™]

Big 'ol wet kiss for Ying!

 

'Rekd teh Why do you keep touching me?!?!

[mikhael gutman]

Hi guys !

Thank you very match to all of you for replay and help.

Many thanks Ying for your help.

You saved me lot off time.

Really appreciate it

It is working now .

Have you guys good weekend