showing the tool next to a tool change

[DCOPE17]

On Mcam 2020 and I want it to post out what the tool is next to the tool change in the program. There is a complete list at the top of the program but its nice when using a lot of tools that when T6 comes up, it says 1/2" endmill so I can know that I set up my tools correctly.

 

How do I get this changed in 2020?

 

Thanks for the help.

Dan

[PEPPERCORN RANCH]

pbld, n$, *t$, ptoolcomment, e$# Move PTOOLCOMMENT to this line. You will have to do this in 2 places

[DCOPE17]

okay, I'll give that a shot. Didn't know it was a post thing, thought I had to check a box in the config somewhere.

Been working on the post too so I'll shoot this in.

Thanks

[DCOPE17]

I have this now...

" pcom_moveb
      pcheckaxis
      c_mmlt$ #Multiple tool subprogram call

      comment$
      pcan
      pbld, n$, *t$, sm06, ptoolcomment, e$
      pindex
      sav_absinc = absinc$"

 

had this...

"pcom_moveb
      pcheckaxis
      c_mmlt$ #Multiple tool subprogram call
      ptoolcomment
      comment$
      pcan
      pbld, n$, *t$, sm06, e$
      pindex
      sav_absinc = absinc$

 

neither posted out the comment

[PEPPERCORN RANCH]

You may have a switch to turn on and off commentint types. Look for this:

tool_info    : 3     #Output tooltable information?
                     #0 = Off - Do not output any tool comments or tooltable
                     #1 = Tool comments only
                     #2 = Tooltable in header - no tool comments at T/C
                     #3 = Tooltable in header - with tool comments at T/C

[DCOPE17]

That was it. Thanks for the help.

Dan