Home on Y

[Randy Morton @ Clem Industrial]

Hey!

 

For this one op I am doing, due to tool clearance issues during a tool change I need to bring the table back to home on Y after every tool operation is finished (right before the M01). How can I do this in MCX, or is this just easier done inputting it into the code myself?

 

Thanks!

[smokey_44]

I would just type the code in for a 1 time thing

 

 

Dave

[Guest]

You could use canned text, and place it before the next tool change.

 

I do this all the time

 

in the canned text section of the post

code:

---

if cantext$ = 6,   [  

pbld, n$, sg91, "G28", "Y0.", e$

pbld, n$, sg90, *g_wcs, "X0.", e$

pbld, n$, sm00, e$

pbld, n$, "(LOOSEN AND RETIGHT VISE)", e$

pbld, n$, "( DO NOT OVERTIGHTEN)", e$

]

---

If you do a seacrch, I did something that I posted the methosd on adding these things in, they are handy to have. TYhen once it is in, it is available to use whenever the situation comes up.

 

Here's a link if you're so inclined

Linky

 

[ 03-15-2006, 09:44 AM: Message edited by: jmparis ]

[MIKE_B]

John

 

I'm playing around with my post here. How do I get my G90 GO WCS, spindle on, to post right? Not sure exactly what I'm missing.

 

 

quote:

---

#Comment from manual entry

scomm$ = ucase (scomm$)

if gcode$ = 1007, "(", scomm$, ")", e$

if gcode$ = 1006, scomm$, e$

if gcode$ = 1005,

[

n$,"G90 G0 Z5. M9", e$

n$,"G91 G28 Y0. M5", e$

n$,"M00", "(", scomm$, ")", e$

n$,"g90, g00, *g_wcs, pfxout, pfyout,

*speed, sm3,e$

], e$

else, "(", scomm$, ")", e$

---

This is what I'm getting

 

quote:

---

N1400 G90 G0 Z5. M9

N1410 G91 G28 Y0. M5

N1420 M00 ( SWITCH CLAMPS TO THE SIDES )

N1430 g90, g00, *g_wcs, pfxout, pfyout, S6000

( MILL FRONT AND BACK STEP )

N1440 X-3.923 Y4.054

---

Thanks

Mike

[Guest]

see if this helps you out at all

 

code:

---

pbld, n$, sm00, e$

pbld, n$, "(CHANGE CLAMPS)", e$

pbld, n$, sg00, *g_wcs, sg90, pfxout, pfyout,

*speed, sm03, e$

pbld, n$, sm08, e$

---

[MIKE_B]

John

 

Thanks that worked