HAAS work offsets

[steve f]

I've recently purchased a Haas mill without the probing and custom macro option. All fixtures, vises, etc will be located on a fixture plate using Jergen's ball-lock so I need a method of pre-setting work offsets.

 

Is it possible to write values from the program header directly to the work offset tables without the custom macro option?

 

All help appreciated.

 

cheers,

 

steve

[somename75]

I am not positive about how haas does it, but on normal fanuc or mazak controlls this is possible by using a G10 command. You might want to look in your haas book and see if that jumps out at ya. HTH

[Guest]

steve

the answere is absolutely yes:

example

O1001(XYZ ZERO)

G90G40G0G54G17G80

G10L2P1X-0Y-0Z-0

G54

M99

 

O1002(XYZ ZERO)

G90G40G0G55G17G80

G10L2P2X-0Y-0Z-0

G55

M99

 

O1003(XYZ ZERO)

G90G40G0G56G17G80

G10L2P3X-0Y-0Z-0

G56

M99

 

O1004(XYZ ZERO)

G90G40G0G57G17G80

G10L2P4X-0Y-0Z-0

G57

 

you can even include in the main program header if you prefer. we just use an m98p100? to call ours.

 

good luck with your haas. dont know for sure but thought custom macro was standard? could very well be wrong, bought mine used and dont know what they origanally paid for.

 

Doug

[PeterM]

g10 is the way to write workshift info into the program, your haas manual has some examples for you. I don't have any experience with jergen's ball lock system but I"ll bet a tooling ball would do the trick.

 

____________________

Peter Martin

mcam 3... - x mr2 - mill level 3

Senior Programmer/Milling Supervisor

Preci Mfg.

400 Weaver St. Winooski VT 05468

PH# 802-655-2487 ext. 231

email [email protected]

[Rick Henrickson The Boeing Co.]

good job on the ball locks, we use them on vertical and horizontal great way to go for quick changeovers

[Zoober]

+1000 on ball locks!

[steve f]

Thanks for the response, G10 is exactly what I'm looking for.

 

The machine is off-site right now and I don't have access to the manuals yet so this gives me a jump start on setting the post up.

[steve f]

DUGCYN from your post...

 

quote:

---

example

O1001(XYZ ZERO)

G90G40G0G54G17G80

G10L2P1X-0Y-0Z-0

G54

M99

---

...what does L2P1 represent on the third line of code? Can I command values from machine zero in XYZ on the third line as well.

 

My goal is to set work offset values for any possible location within the working zone so locating the stock manually is completely eliminated. As an example I'd like the setup guy to lock the vise at location A1, run the program and make small adjustments only if necessary.

 

I like your method of using sub-routines...keeps it simple.

[chris m]

G10 and how to use it are located in the G and M code section of the Haas book; page 200 in mine.

 

L2 is for 'standard' WOFS locations [G52, G54-G59]

The P word specifies individual locations

 

 

L2 P0 would be G52

L2 P1 would be G54

L2 P2 would be G55

 

etc

[Guest]

thanks chris your right on it.

Doug