Okuma Mill Macro help

[Mr.ZX]

I have an Okuma mill with a OSP control. I need a macro that I can use for tool length measurement. Are there any Okuma Macro Gurus out there that can help? I can program macros on Fanuc and Hass all day long, but do not have time to learn the "Okuma" way right now.

 

Let me know

[Randy Morton @ Clem Industrial]

I have the okuma tool measure macros for a horizontal at home. If nobody chimes in by tomorrow morn, I will try my best to bring them.

[Rick Henrickson 65]

do you have a tool presetter on your mill and is it vertical or horizontal and which osp control

osp 2000 (kidding)

[Mr.ZX]

No tool presetter, I am going to make a preset post that will use an indicating type of presetter. I want to be able to type a command, have the tool put into the spindle, and go to the preset point. Also it must set G15H0. I wrote a couple of them for Fanucs and Hass, but the Okuma language is different.

Control type OSP-U100M

[Rick Henrickson 65]

oh ok

are you going to use G15 H0 as your position for the presetter.

I would probably use VC1 and VC2

you could say in the macro

N01

IF [VC1 LE VC2] GOTO N10

GOTO NEND

N10

IF [VATOL EQ VC1] N20

T=VC1 M6

N20G00 X0. Y0. G15 H0

M0(measure tool use mid auto manual)

G00 Z20.0

VC1=VC1+1

GOTO N01

NEND M30

 

its been awhile and I dont have my manual here with me but that should get you close.

 

so you would set VC1 to your starting tool number and VC2 to your ending tool number

then it will run the loop till it reaches there.

you could assign this macro to an MCODE then fire it from MDI also.

[Mr.ZX]

Thanks, I noticed the M0. Okuma works different than Fanuc. Can you do a mid program handle interrupt? I tried running a regular program and it would not allow this.

[Rick Henrickson 65]

yes, you can even do it with slide hold.

(caution you must get the tool close to wear you left off or it will cut right through your part!)

you just hit slide hold or M0 press mid auto manual

run your table around

put it back roughly where you left it

press mid auto off

Do Not hit cycle start

push sequence restart I am going off an old memory but it is something like that

hey if the power goes out you know you can restart your Okuma exactly where you left off?

pretty handy for a huge stitching job

[Slixmix]

I have a good idea. Call Mike Caffaro and have him put a laser tool setter in the machine!

[Mr.ZX]

Laser! right! "not in the budget" they always say!

So I make due and improvise.

[Greg Williams]

Here ya go

 

OTOOL (PROGRAM NAME)

(************TO CALL**********)

(G111 MEASURES THE TOOL IN THE SPINDLE)

(G111 T1 [sELECTS THE TOOL AND MEASURES IT])

(NOTE: THE TIP OF THE CUTTER MUST BE IN LINE WITH THE KEY)

(AND THE CUTTER RADIUS MUST BE SET)

(SET CUTTER RADIUS FOR BORING BAR TOOLS ALSO)

(TIPPED TOOLS CAN BE MESURED WITH G111 PA=??)

(G15 H20)

IF [PA NE EMPTY] N1

PA=0

N1

IF [PT EQ EMPTY] N4 (IF T IS NOT SET GOTO LINE 4)

IF [VTLCN EQ PT] N4 (IF T=TOOL IN THE SPINDLE GOTO LINE 4)

IF [VNTOL EQ PT] N3 (IF T=NEXT TOOL GOTO LINE 3)

IF [VNTOL EQ 0 ] N2 (IF NEXT TOOL IS VACANT GOTO LINE 2)

M64 (CANCEL PRE-SELECT TOOL)

N2

T=PT (PRE-SELECT COMMANDED TOOL)

N3

M06 (TOOL-CHANGE)

N4

CALL OO30 PX=[VTOFD[VTLCN]] VFST=#81H PRS=PA

(TOOL GAUGE CYCLE)

RTS (END)