Charmilles 440 millenium Control

[CNC101]

Hello, we have X5 and are running two charmilles wires 440 and 390 with millenium control, we recieved a new post and it is WAY different than ou previous one, I need a post or example program from someone so I can see what is or is not nesasary, in the output code. This is the program for a 2 inch circle 4 cuts from the new post. Appreciate all help.

 

New Post

%

O0001

N100 G90

N110 G92 X0. Y0.

N120 G11 ( TEC, 1 )

N130 M15 P0

N140 S501

N150 M60

N160 G92 G0 X0. Y0. I1. J0. H0

N170 G41 D1 G1 X1.

N180 G3 X-1. I-1. J0.

N190 X1. I1. J0.

N200 G40 G1 X0.

 

N210 M15 P0

N220 S502

N230 G92 X0. Y0. I1. J0. H0

N240 G42 D2 G1 X1.

N250 G2 X-1. I-1. J0.

N260 X1. I1. J0.

N270 G40 G1 X0.

 

N280 M15 P0

N290 S503

N300 G92 X0. Y0. I1. J0. H0

N310 G41 D3 G1 X1.

N320 G3 X-1. I-1. J0.

N330 X1. I1. J0.

N340 G40 G1 X0.

 

N350 M15 P0

N360 S504

N370 G92 X0. Y0. I1. J0. H0

N380 G42 D4 G1 X1.

N390 G2 X-1. I-1. J0.

N400 X1. I1. J0.

N410 G40 G1 X0.

N420 M50

N430 M30

%

[mikeqes]

Hi,

I run a 240 here with Mil. Control. The one thing I notice is that on line N170 it is outputting a D1 to force a off set. With

my machine this always has to be set as a D0 (on all cuts) or it wont take the off set value. This is done in the power library parameter

page. I always have to fix this when I upgrade to a new version of MC. Keep this in mind if you run a test cut and the off set does not take.

 

This is what my post spits out for that program:

 

%

O0001

N100 G90

N110 G92 X0. Y0.

N120 M31

N130 G11 (TEC,TEST)

N140 G11 (WIR,XS25)

N150 M50

N160 G00 X0. Y0.

N170 S501

N180 G92 X0. Y0. H1. J0. I1.

N190 M60

N200 M24

N210 M28

N220 G41 D0 G01 X1.

N230 G03 X-1. I-1. J0.

N240 X1. I1. J0.

N250 G40 G01 X.99

N260 M24

N270 M28

 

N280 G11 (WIR,XS25)

N290 S502

N300 G92 X.99 Y0. H1. J0. I1.

N310 G42 D0 G01 X1.

N320 G02 X-1. I-1. J0.

N330 X1. I1. J0.

N340 G40 G01 X.99

N350 M24

N360 M28

 

N370 G11 (WIR,XS25)

N380 S503

N390 G92 X.99 Y0. H1. J0. I1.

N400 G41 D0 G01 X1.

N410 G03 X-1. I-1. J0.

N420 X1. I1. J0.

N430 G40 G01 X.99

N440 M24

N450 M28

 

N460 G11 (WIR,XS25)

N470 S504

N480 G92 X.99 Y0. H1. J0. I1.

N490 G42 D0 G01 X1.

N500 G02 X-1. I-1. J0.

N510 X1. I1. J0.

N520 G40 G01 X.99

N530 M50

N540 M15 P0

N550 M30

%

 

Hope this helps,

Mike

 

 

 

 

 

 

Hello, we have X5 and are running two charmilles wires 440 and 390 with millenium control, we recieved a new post and it is WAY different than ou previous one, I need a post or example program from someone so I can see what is or is not nesasary, in the output code. This is the program for a 2 inch circle 4 cuts from the new post. Appreciate all help.

 

New Post

%

O0001

N100 G90

N110 G92 X0. Y0.

N120 G11 ( TEC, 1 )

N130 M15 P0

N140 S501

N150 M60

N160 G92 G0 X0. Y0. I1. J0. H0

N170 G41 D1 G1 X1.

N180 G3 X-1. I-1. J0.

N190 X1. I1. J0.

N200 G40 G1 X0.

 

N210 M15 P0

N220 S502

N230 G92 X0. Y0. I1. J0. H0

N240 G42 D2 G1 X1.

N250 G2 X-1. I-1. J0.

N260 X1. I1. J0.

N270 G40 G1 X0.

 

N280 M15 P0

N290 S503

N300 G92 X0. Y0. I1. J0. H0

N310 G41 D3 G1 X1.

N320 G3 X-1. I-1. J0.

N330 X1. I1. J0.

N340 G40 G1 X0.

 

N350 M15 P0

N360 S504

N370 G92 X0. Y0. I1. J0. H0

N380 G42 D4 G1 X1.

N390 G2 X-1. I-1. J0.

N400 X1. I1. J0.

N410 G40 G1 X0.

N420 M50

N430 M30

%

[bamavick]

I am using X4 running 240, 440 and CC machines. This is what my code looks like on a 1" thick part.

Hope this helps.

 

 

 

O0001

( CHARMILLES ROBOFIL 4X WIRE )

N10 G90

N20 G92 X0. Y0. H1.

N30 G11 ( TEC,1CUT1000 )

N40 M15 P0

N50 S501

N60 M60

N70 G92 G00 X0. Y0. I1. J0.

N80 G41 G01 Y1.

N90 G03 X-1. Y0. I0. J-1.

N100 X0. Y-1. I1. J0.

N110 X1. Y0. I0. J1.

N120 X.001 Y1. I-1. J0.

N130 X0. I-.001 J-1.

N140 M00

N150 G40 G00 Y.99

 

N160 M15 P0

N170 S502

N180 G92 X0. Y.99 I1. J0. H1.

N190 G41 G01 Y1.

N200 G03 X-1. Y0. I0. J-1.

N210 X0. Y-1. I1. J0.

N220 X1. Y0. I0. J1.

N230 X0. Y1. I-1. J0.

N240 G40 G00 Y.99

 

N250 M15 P0

N260 S503

N270 G92 X0. Y.99 I1. J0. H1.

N280 G41 G01 Y1.

N290 G03 X-1. Y0. I0. J-1.

N300 X0. Y-1. I1. J0.

N310 X1. Y0. I0. J1.

N320 X0. Y1. I-1. J0.

N330 G40 G00 Y.99

 

N340 M15 P0

N350 S504

N360 G92 X0. Y.99 I1. J0. H1.

N370 G41 G01 Y1.

N380 G03 X-1. Y0. I0. J-1.

N390 X0. Y-1. I1. J0.

N400 X1. Y0. I0. J1.

N410 X0. Y1. I-1. J0.

N420 G40 G00 Y.99

N430 M50

N440 M30

%

[88Matt]

mikeqes,

 

I always have to fix this when I upgrade to a new version of MC.

 

When you make your changes, save it as a new power library (***.power) and you won't have to reset all the settings to the default file when you upgrade.

[CNC101]

Thanks for the input, our old post has a G75 X0.00 Y0.00 before the G92 X0 Y0 so it moves to zero before it starts, I dont see that in your programs do you just make sure you are at zero when you hit go?

[CNC101]

We also have a G90 G10 P16 R0.000 at the beginning to control size if needed, How do you guys leave say .0005 in the hole if you wanted to? If the cad is not perfect do you redraw it? And do you enter a Z value for the head height?

 

here is our old post

 

%

O0000

G90 G10 P16 R0.000 ( 2 INCH CIRCLE OLD POST )

G11 (TEC,1)

N5 G11 (WIR,LS25)

M15 P1

M31

N10 G0 G20 G90

N15 G0 X0. Y0.

N20 G75 X0. Y0.

N25 G0 Z5.

N30 G0 X0. Y0.

N35 G92 X0. Y0. I1. J0.

N40 G92

N45 M60

N50 M28

N55 M24

 

N60 S501

N65 G41 G1 X1.

N70 G3 X-1. I-1.

N75 X1. I1.

N80 G40 G1 X0.

N85 G0 X0. Y0.

N90 X0. Y0.

 

N95 S502

N100 G42 G1 X1.

N105 G2 X-1. I-1.

N110 X1. I1.

N115 G40 G1 X0.

N120 G0 X0. Y0.

N125 X0. Y0.

 

N130 S503

N135 G41 G1 X1.

N140 G3 X-1. I-1.

N145 X1. I1.

N150 G40 G1 X0.

N155 G0 X0. Y0.

N160 X0. Y0.

 

N165 S504

N170 G42 G1 X1.

N175 G2 X-1. I-1.

N180 X1. I1.

N185 G40 G1 X0.

N190 M50

N195 G90 G10 P16 R0.000

M35

M30

%