HAAS Live Tool Code

[ConcordWS]

Good afternoon all.

 

I'm fighting with my post,

 

Could someone / anyone do a quick program of a C axis face contour of a 1 7/8" ID Square with a 5/16" endmill with computer comp and put it up so I can compare code?

Machine is a HAAS ST40.

 

Pulling my hair out.

 

Thanks,

 

Brett

[ConcordWS]

I'm used to just doing this on Okumas with IGF.

 

Looking at the HAAS manuals, if it output "Y" moves instead of "C", G112 will convert it in the background into a "C" movement.

 

This is what I'm getting for code.

 

G20

(TOOL - 5 OFFSET - 5)

( 5/16 FLAT ENDMILL)

( MILL 1 7/8" SQUARE )

G0 T0505

M154

M8

G0 G54 X1.2189 Z2.

C11.503

G97 P1711 M133

Z.1

G98 G1 Z-.5 F5.

X1.5284 C356.685 F377.37

G98 G3 G112

X1.5626 C0. R.0624 F6.

G1 X1.5625 C.7813

X-1.5625

C-.7813

X1.5625

C0.

C.1

G113

G3 X1.5528 C10.704 R.0625 F427.36

G1 X1.1952 C357.935 F325.46

G0 Z2.

 

I started off with the Generic Fanuc 4X MT post. Most of it is working ok except for this c axis face contour.

[Rocketmachinist]

My post is far from perfect but this is what I get;

 

%

O0000 (LIVE TOOL CHECK)

(DATE=DD-MM-YY - 17-12-12 TIME=HH:MM - 10:47)

(MCX FILE - C:\USERS\ASMURPHY\DOCUMENTS\ELECTRODES MAIN FILES.MCX-6)

(NC FILE - C:\USERS\ASMURPHY\DOCUMENTS\MY MCAMX6\LATHE\NC\LIVE TOOL CHECK.NC)

(MATERIAL - STEEL INCH - 1030 - 200 BHN)

(POST DEV - IN-HOUSE SOLUTIONS INC.)

(POST DEV - IN-HOUSE SOLUTIONS INC.)

(TOOL - 236 - 5/16 FLAT ENDMILL - OFFSET - 236 - DIA. - 0.")

G17 G20 G40 G54 G80 G99

(TOOL - 236 OFFSET - 236)

( 5/16 FLAT ENDMILL)

N1 T23836

G28 U0.

G28 W0.

G54 G0 Z10.

X10.

G98

M154

M15

G0 C0.

G0 X2.8811 Z.25

G97 P1711 M133

G112

G17

X-2.1875 Y-.9375

Z.1

G1 Z0. F6.37

G41 Y.9375

G2 X-1.875 Y1.0938 R.1563

G1 X1.875

G2 X2.1876 Y.9375 R.1563

G1 X2.1875 Y-.9375

G2 X1.875 Y-1.0938 R.1563

G1 X-1.875

G2 G40 X-2.1876 Y-.9375 R.1563

G0 X-2.1875 Z.25

G113

G18

G28 U0.

G28 W0. M135

M30

%

[ConcordWS]

My post is far from perfect but this is what I get;

 

Thanks for the tease. I think that's what I'm looking for for code.What post did you start with?

I've got an email in to reseller for post work.

Tried another post MPLFAN. Didn't help.

[Chris Bloedorn]

Try looking in your Misc options here...

 

[Rocketmachinist]

I'm using Haas SL 4X Mt post written by InHouse.

 

There was some things that I still need fixed on it. Canned drilling is messed up a little, I don't have peck cycles for live tooling and there was a problem when I first got the post of certain items being too close together.

 

It was something like M154 and M15 are to close together. The spindle is still unclamping when it goes to engage the caxis. It works fine single blocking through but when you try to run everything from start to finish it overloads the caxis drive motor and the machine errors out.

[Rocketmachinist]

Correction it is the MPLMaster_haas.pst post