Translating toolpaths

[George_Gerhard]

Hi All!

I have a toolpath to copy, so I use transform-translate, set everything, I want sub programs so I check that too. It works ok. In the operations manager there is the parent operation and the transform results. When I post it the first part is coded as a stand alone part and the rest are subs. Does anyone know how I can make the first part a sub also. Im just trying to streamline the nc file, so all I see is position and sub call.

 

thank you

George

 

remember to put the wheels down before landing

[crazy^millman]

Well depending on the operation I am not sure if you can make the parnet a sub unless you post supports that. The old Fadal subroutine does support this but not sure what machine or it that would help you.

 

Crazy Millman

[George_Gerhard]

Thanks Millman, I can trick it easy enough, Ive been sitting here the last few minutes looking through the post.

 

I guess we are all from zion today

My son just waited an hour on line for tickets

[Brendan P]

George,when I use the "translate function,I do not post the source operation.

I only post the "translated or "rotated" toolpath and do not have this problem.

 

Example: If you want to rotate 4 times at 90 deg.

then put (4) in the number of steps in the rotate params. start angle would be zero,and rotation abgle would be set to 90 deg.

 

Then only post the "translated toolpath.

It may say "not all op's selected for posting"

but this is ok.

 

Hope this helps

[George_Gerhard]

Thanks Bucket

thats what I'll probably do

 

regards

George

[crazy^millman]

I have found lately if you turn off posting in source operation you dont have any problem what so ever.This will be a little long but here is how Tranfor mdoes it this frist way.

code:

---

O0900 (T)

(MC9 FILE - C:MCAM91MILLMC9OCTOGON PART.MC9)

(PROGRAM LOCATION - C:MCAM91MILLNCT.NC)

(DATE - NOV-05-03)

(TIME - 19:27)

(T1 | 1/8 CENTERDRILL | H0 | D0 | D0.1250" | | PECK DRILL.)

(T207 | 1/2-13 TAPRH | H0 | D0 | D0.5000" | | TAP........)

(T10 | 1/2 DRILL | H10 | D10 | D0.5000" | | TAP........)

(OVERALL MAX | Z6.)

(OVERALL MIN | Z1.)

G0G17G40G80G90

T1M6( 1/8 CENTERDRILL)

(MAX | Z6.)

(MIN | Z2.75)

G0G90E1X0.Y0.S2139M3

H1Z6.M8

G4 P2000

G8

M98P0901L1

G0E2X0.Y0.Z6.

M98P0901L1

G0E3X0.Y0.Z6.

M98P0901L1

G0E4X0.Y0.Z6.

M98P0901L1

G0E5X0.Y0.Z6.

M98P0901L1

G91G28Z0.

M1

T207M6( 1/2-13 TAPRH)

(MAX | Z6.)

(MIN | Z1.)

G0G90E1X0.Y0.S534M3

S534.2M5

G84.2

H207Z6.M8

G4 P2000

G8

M98P0902L1

G0E2X0.Y0.Z6.

M98P0902L1

G0E3X0.Y0.Z6.

M98P0902L1

G0E4X0.Y0.Z6.

M98P0902L1

G0E5X0.Y0.Z6.

M98P0902L1

G91G28Z0.

M1

T10M6( 1/2 DRILL)

(MAX | Z6.)

(MIN | Z1.)

G0G90E1X0.Y0.S1500M3

S1500.2M5

G84.2

H10Z6.M8

G4 P2000

G8

M98P0903L1

G0E2X0.Y0.Z6.

M98P0903L1

G0E3X0.Y0.Z6.

M98P0903L1

G0E4X0.Y0.Z6.

M98P0903L1

G0E5X0.Y0.Z6.

M98P0903L1

G91G28Z0.

M02

 

O0901

G91

G83G98X0.Y0.Z-.35R0-2.9Q.1F1.03

X0.Y2.4

X0.Y2.4

X0.Y2.4

X0.Y2.4

X0.Y2.4

G80

G90

M99

 

O0902

G91

G84.1G98X0.Y0.Z-2.1R0-2.9F534.2Q.0769

X0.Y2.4F41.14

X0.Y2.4

X0.Y2.4

X0.Y2.4

X0.Y2.4

G80

G90

M99

 

O0903

G91

G84.1G98X0.Y0.Z-2.1R0-2.9F1500.2Q0.

X0.Y2.4F4.28

X0.Y2.4

X0.Y2.4

X0.Y2.4

X0.Y2.4

G80

G90

M99

---

That is done with Transform.

 

Crazy Millman

[heeler]

Toolpaths, Transform, Check copy source ops, Disable posting, and Subprograms. Post.

 

If you select all the toolpaths for backplot or verify, it will show you the 'Parent' op. If you just select the Transform op, It will show only the ones that the machine will run and the order it will run them.

 

We use this all the time.

 

HTH

Glenn

[Chris Rizzo]

+1 Heeler,

That's the way I've found translate to work best as well...plus you get that cool little ghost icon!

However it's good to be aware that when you backplot it WILL run the source op, (basically by performing the source operation twice on screen- once for the original, once for the transform)...when you post it though it dumps the source op.