Need F0 with G00

[TFesta]

I just downloaded the newest MasterCam-V8 post. I have an old Allen-Bradley control. I have the post working great except how do I get it to output a F0 in the same block as the G00?

[Craig-B]

Try to find this line in your post(sg00 G00 #Rapid) Then change it to this(sg00 G00F0 #Rapid). I had to do that for my Kearney & Trecker 180 HMC's.

[TFesta]

Yeah FNMI that works. I was hoping for something to were the computer knows it put in the F0 code, cause if you don't have different feed rate numbers on plunge and reg feed the computer only puts in one feed rate. So after it rapids when it goes to feed again it takes the F0 as a feed rate, not nice. But thank's, that will work till I can find something else.

[Storkman]

Sorry, no ver 8. but you should have a similar line in your post. you could just add the feed to it. You might have to put feed=0 befor it.

 

prapidout #Output to NC of linear movement - rapid

pcan1, pbld, n, sgplane, `sgcode, sgabsinc, pccdia,

pxout, pyout, pzout, pcout, strcantext, scoolant, e

 

 

New:

 

 

prapidout #Output to NC of linear movement - rapid

 

feed = 0

pcan1, pbld, n, sgplane, `sgcode, sgabsinc, pccdia,

pxout, pyout, pzout, pcout, feed, strcantext, scoolant, e

[Craig-B]

Try adding this (prv_feed = 999.999)under prapidout. This should fix that I should look like this.

 

prapidout #Output to NC of linear movement - rapid

pcan1, pbld, n, sgplane, `sgcode, sgabsinc, pccdia,

pxout, pyout, pcout, strcantext, e#scoolant, e

pcan1, pbld, n, sgplane, `sgcode, sgabsinc, pzout, e

prv_feed = 999.999 This is what I put in my post.

[TFesta]

The feed=0 works great. Thanks Storkman

[Storkman]

glad to help