X Post Question

[Karl@CP PISTONS]

After updating ver 9 post to X all g-code is on 1 line. Is there something easy I'm missing?

Karl

[Tom Dorgan from American Precision]

Karl,

Yes, you have to open your Machine Definition and Control Definition and make the edits in there to match your machine. Some are easy and some are not. All my routers are 3 and 4 spindle machines and I have a hard time getting them setup correctly for some reason.

[Karl@CP PISTONS]

I could not find any setting that controls the end of line. It is as if the post does not put any end of line codes. All hard-coded lines are correct. G-Code looks like this:

G00X1.2345Y1.345G1X1.Y2.Z2.F40.S2800M3G0T8M6G0X1.23Y2.43B0.0G3X1.Y2.I3.4J4.F30.G2X1.234.....til the end of the code.

Karl

[crazy^millman]

You are missing $ after some e's in the post. i would send that to [email protected] so they can log that problem you are having.

 

HTH

[Karl@CP PISTONS]

I did a search of this post and found no e's without $'s (except for notes etc.).

[Christian Raebild]

On the NC Output page in the control definition you have both a "Remove CR/LF..." option and an "Alternate EOB..." option. If you have the "Remove CR/LF..." option checked, or have the "Alternate EOB..." option checked and set up for different characters from what your CNC needs, then that would explain your problem.

 

If you e-mail me a sample NC code file, then I can check exactly which EOB characters (if any) are output, using a hex editor. If you also include a sample from v9 that is correct, then I can also tell you what you need to set in the control definiton (please remeber to note which of the two samples is the correct one).

[Karl@CP PISTONS]

Christian,

I have looked at the control definition and neither the remove cr/lf or alternate eob boxes are checked.

I will e-mail you the nc code in a second.

Thanks

Karl

[Christian Raebild]

I have looked at the files. Having neither of those options checked will generate the correct CR/LF sequence when the post processor generates a CR/LF sequence. However, there are no CR or LF characters in the section that shows as a single line.

 

You must be missing some ", e$" bits (withput the quotes) in your post processor. You will need to find the postblocks that output rapid, linear and arc moves, they most likely have names like prapidout, plinout and pcirout. You will have to place a ", e$" (without the quotes) at the end of the output line in each of those postblocks. Please note, that the output may be divided into two lines in the postblock, where the first of the two lines ends in a comma. In that case, you only need to add the ", e$" sequence to the last of those lines. You might also need to append the ", e$" sequence to lines in other postblocks, I can only see from the sample you sent me, that it is necessary in those output postblocks.

 

The reason for this "error" is, that the updatepost utility only appends the e$ to output lines in predefined postblocks, it does not append it to output lines in user defined postblicks as those lines may be intended to be part of a longer line, as the user defined postblock might be called in the middle of an output line in another postblock.

[Karl@CP PISTONS]

Thanks for the quick reply

Adding the , e$ to the prapid, plin, and pcir fixed the problem.

Nothing can beat this forum for the quality of the responses.

Karl