Mitisubishi Wire edm Post

[PERRY C]

I'm cutting some large shapes on a detail the first 2 cuts are angled and the last one is a land cut. My question is when I post it out using subprograms I have a stop point programed so I can pull the slug when it burns through and on the other 2 passess I dont need it to stop. The post is outputting a block delete / and I rather it output an M01. Where in the post might I find the string I need to change to have it output m01 instead of block delete I guess that's my real question?

 

X-2 MR SP1

Mill Level 3

Wire Level 2

Solids

[PERRY C]

N260 Y.03

N261 Y.2602

/ N262 M00 (This is what it's posting)

N263 Y.3

N264 Y.02

 

N260 Y.03

N261 Y.2602

N262 M01 (This is what I'm wanting it to post)

N263 Y.3

N264 Y.02

 

Thanks in advance

[Kannon]

Under your cuts tab.. it asks how you want to output your stop code..

 

Can you output it as a "glue stop"

instead of a "as stop point"?

 

I am looking at version 9.. but bet its similiar..

[PERRY C]

Thanks I'll try it and see.

[PERRY C]

That gives me the M01 I wanted it leaves the / in but as long as the block delete isn't turned

on it should work.

I have another question. I'm cutting taper on the first 2 passess and land cut on the last pass. Only thing is when you select taper it post the angle in the sub-program and it actually needs to be in the main program other wise all 3 passess are cut on the taper angle.

I usually don't use sub-programs programming because the openings are smaller but these and larger and a lot of little lines so I decided to program it using subs to hold down on program size.

[Kannon]

under your contour parameters there is a tab with a drop down that allows you to cancel taper angle after the amount of passes you dictate.

it allows you to taper all passes..

cancel taper after pass...

or apply taper after pass...

 

have you checked that out to make sure that is set correctly..

 

should be able to do this in one wire path contour... set the rough with your taper angle and set the number of skims you want canceling taper after pass number.. then set your number of skims to your liking. it should post out with taper in your first sub..then none in second.

 

hth

[PERRY C]

That's how I normally do it. I tell it to cancel taper after pass 2 and it does. But when I told it to out put subs it only outputs one sub and it has the angle in it. But what I do is remove the angle from the sub and place it in the main on the line with the e-pack and offset and feedrate and that works but if I could get it to do it without manually modifiying the program would be nice.

[PERRY C]

I just checked and the only thing left is apply taper after pass and that doesn't work because I need it on the first 2 passess.

[PERRY C]

Here's what it post out if I check cancel after pass

%

L017

(03/20/08)

 

H1 =.0093

H2 =.0065

H3 =.0064

 

Z1 =1.2500

Z2 =1.2500

Z3 =1.9038

Z4 =0.3124

Z5 =0.0000

N1 G90

N2 G0 X8.7246 Y-.5951

N3 M00 (THREAD WIRE)

N4 M78 M78

N5 M80 M82 M84

N6 E1450 H1 F.02

N7 M90

N8 G22 L005

N9 E1452 H2 F.09

N10 G22 L005

N9 E4992 H3 F.09

N10 G22 L005

N9 M85 M83 M81 M58

N10 M00 (CUT WIRE)

N11 M21

N12 M58

N13 M02

 

 

L005

N1 G92 X8.7246 Y-.5951

N2 G91

N3 G41 G1 X.2113 Y-.02 A-.5 ( angle )

N4 G3 X.02 Y.02 I0. J.02

 

This is how I modify it and it works but if I could edit the post to post out like this would be nice. Then you'd only have one sub for all 3 cuts.

%

L017

(03/20/08)

 

H1 =.0093

H2 =.0065

H3 =.0064

 

Z1 =1.2500

Z2 =1.2500

Z3 =1.9038

Z4 =0.3124

Z5 =0.0000

N1 G90

N2 G0 X8.7246 Y-.5951

N3 M00 (THREAD WIRE)

N4 M78 M78

N5 M80 M82 M84

N6 E1450 H1 F.02 A-.5

N7 M90

N8 G22 L005

N9 E1452 H2 F.09 A-.5

N10 G22 L005

N9 E4992 H3 F.09 A0.

N10 G22 L005

N9 M85 M83 M81 M58

N10 M00 (CUT WIRE)

N11 M21

N12 M58

N13 M02

 

 

L005

N1 G92 X8.7246 Y-.5951

N2 G91

N3 G41 G1 X.2113 Y-.02

N4 G3 X.02 Y.02 I0. J.02

[PERRY C]

I just tried reversing the direction and it post out 2 seperate subs but both have the angle in the sub so I'd still would have all 3 passes cut on a taper.

[Matthew Hajicek - Singularity]

You can always hand edit the code a little.

[PERRY C]

That's what I'm doing now. But if I could edit the post the other 2 programer/operators on 2nd and 3rd Shift wouldn't have to and I wouldn't have to explain what they have to change, they could just post it and go.

[Jerry_P]

You say you are subbing the main program (The part contour). Could you just change the A in the post to A=H50 for example then in the main program have H50= what ever taper you want. So H=0 would not cut taper and H=-5.0 would put a 5 degree taper in the part.