Post tweak help?

[mcpgmr]

I have a Fortune Mill that has 24 tool pockets but I use 25 tools using the spindle as the 25th pocket. My problem is I can't call the 25th tool T25. It has to be T0 with H25 or whatever length offset I desire within the range of the offset register. I would like to force the post to out put H25 and D25 when ever it encounters T0. In X2 I can adjust it in the ops manager but it doesn't always stick. The result would be a crash because it defaults to H0 D0 when it sees T0. The reason I have it setup like this is because I have dedicated tooling for this machine and a tool library in X2 for that machine and I don't want to change anything at this point. Any help would be appreciated. Thanks in advance!

[Russell Jennison]

Hi Paul. Probably the easiest fix will not make you happy. Currently using T0 allows the programmer to error because you have to type in your H25 D25 every time.

 

If on the other hand you actually used mastercam Tool number 25 and made it identical to your T0, then you could use something like the following to correct the tool number in the post. There is likely to be a section like the following:

 

if stagetool >= zero,

[

if omitseq$ = 1 & tseqno > 0,

[

if tseqno = 2, n$ = t$

pbld, *n$, *t$, "M06", ptoolcomm, e$

]

else, pbld, n$, *t$, "M06", ptoolcomm, e$

]

 

If you add in the following it should always output T25 as T0 but won't affect the offsets associated with T25.

 

if stagetool >= zero,

[

if t$ = 25, t$ = 0

if omitseq$ = 1 & tseqno > 0,

[

if tseqno = 2, n$ = t$

pbld, *n$, *t$, "M06", ptoolcomm, e$

]

else, pbld, n$, *t$, "M06", ptoolcomm, e$

]

 

Just an idea. Let us know if that solves your issue.

 

Regards,

 

Russell Jennison

Post Development

In-House Solutions Inc.

http://www.inhouseposts.com

http://www.emastercam.com

[mcpgmr]

Thanks Russel! I'll give it a try.

[J Coulston]

I fought this same issue, I fixed in my machine parameters. Look in you machine parameters and find where you tool numbers are are stored. Change the 0 to 25.

[mcpgmr]

Well the post change did not work. I'm going to look into the machine parameter next. For now I just have to search for H0 in the code before I release it to the shop. Thanks for the help guys!

[Tim Johnson]

:rewritten

 

Try this;

 

look for tlngno$(s) in your post and in the line before add

code:

---

      if t$ = 0, tlngno$ = 25

---

then in postblock pccdia;

 

code:

---

pccdia          #Cutter Compensation

#Force Dxx#

if t$ = 0, tloffno$ = 25 # <<<<<<<<<<<< add

if prv_cc_pos$ <> cc_pos$ & cc_pos$, prv_tloffno$ = c9k

sccomp

if cc_pos$, tloffno$

---