mpmaster post one tool

[Eric S.]

Hi

 

I am using the mpfan post foe my HAAS VF3 anf VF2 mills. If I am only using one tool the post does not output a tool change call out. I would like it to output a t* M06 even for one tool but am lost when looking at the post any ideas?

thanks

[Thad]

I'm probably not much help here, but if it was me, I would open the post with any word processor and do a search for things like "T", "tool", "M6", "toolchange", etc. Read the surrounding area and maybe something will jump out at you. If you have good problem solving skills, you may be able to figure it out on your own. I've made very minor post changes like this. Sorry, but that's the only help I can give you. Good luck.

 

Thad

[Garen Cakmak/CAP Tech.]

Hi Eric

 

The MPfan outputs that line, it has the logic in it, what version of the post are you using and what version are you running of Mastercam, if your using V9, download the Mill9posts.exe in the patch section,(if you haven't done any modification on it)and it should work without and problem if not i need more info to help you out.

[Roger Martin from CNC Software]

Eric,

 

Here is how to handle this...

 

You must have pre-staging tools set ON (this is OK it you need it)

stagetool : 1 #0 = Do not pre-stage tools, 1 = Stage tools

 

With this option enabled this will eliminate the call for the FIRST tool if there is only ONE tool in the program.

 

Easy to fix...

Add a "#" to this line in the post to have the first tool call output, even with stagetools enabled and only one tool in the program ->

(Search for "ntools" to find the area in the post to be changed)

 

if ntools = one,

[

#skip single tool outputs, stagetool must be on

#stagetool = m_one <<<--- COMMENT OUT THIS LINE

!next_tool

]

[Michael Reynolds]

Hi Eric!

 

When you are in the tool parameters page, click on

"change nci", then check the "force tool change" box. You could also go into screen, config, and set that as permanent.

 

Hope that helps!

 

Mike R.

[Eric S.]

Thanks for the help guys I have it working now.

I changed the post like you said Roger and it worked great! Also thanks to you michael. I did not know about the "force tool change" in the "change nci" either this will also come in handy in future programing!

Thanks again