How are tools numbered in multi-task machines?

[Bruce Caulley]

Ahoy?

 

In an integrex/macturn type machine, how are the tools numbered between main spindle and lower turret? Lets say I have one with a sub-spindle and lower turret. The lower turret has 12 tools on both sides and the upper milling turret has 80. To complicate things, a few of the upper "milling" ones are multi-function turning tools with multiple inserts used at 0,90,180,270 degrees.

 

How does that work on paper if you are trying to lay out a tool list?

 

thanks

 

Bruce

[Mic6]

after readin; that...BEER ME! wish I could help

[Ron Branch @ Verisurf]

Bruce the Integrex handles this well IMHO. The suffix with the tools for the eia varaibles is so cool. So if you take a turning tool like we do and use it for the front spindle and the back spindle you just use the letter. I went a step further and made a spread chart for all tools. Our tools then follow that method and the cool thing is the heavy tool call so we have over 50 tool names for each tool that can be used. So back to that turning tool that is for the front and back well you could go a step further and use that tool in the front spindle in the forward and backward position and then the same thing with with sub spindle. So that tool would then use

T17.17 and that would look like T17 R to the Mazatrol but now to reverse the tool for the main you set the tool up in the set-up page is where you would make the machine call it up for the main so you could use T17.18 to then reverse the tool to then use again on the main spindle. Ok that seems pretty straight forward right until we need it for the sub spindle so we could use the same T17.17 for the reverse of the spindle and then the T17.18 for the forward of th3e spindle on the reverse but then when it is called in the program how would the operator know what was the tool doing for the spindle. So with the Heavy capability for tool calls it then uses T17.77 which is T17 Heavy R for Mazatrol. Now we have a method for the machine to know which is which for the direction and spindle and for the programmer and the operator.

 

I think I explained that well enough not to really make your brain hurt lolol. Ok that tool could then be put and different angles so no you could rotate the tool 30 degree then run it forward and reverse and then you can use it at 45 degree and again forward and reverse and then again and again for each angle. So you build tools along and along. I then label it as such on my set up sheets and life is good.

 

Ok the missing piece of the puzzle is the post from In-House has this built into it and it just a mr number and I get all my tools labeled like I need and life is good. Off to bed I will add tomorrow if you got any questions.

 

HTH

[Greg Williams]

Bruce Macturn has one program that splits into 2 streams

 

G13 upper

G14 lower

 

So we can have 2 off tool 1 etc

 

N0001 G13

N0002 P0010

N0003 G00 X800 Z1000

N0004 G50 S2000

N0100 G13

NAT01

N0101 G97 S884 M42 M03 M08 P0030

N0102 G00 X108 Z4 T010101

N0103 G96 G110 S300 P0040

N0104 G85 N0105 D3 F0.8 U0.4 W0.2 P0050

N0105 G81

N0106 G00 X35

N0107 G01 Z0 G42 E0.8 P0010

N0108 Z-30 P0020

N0109 G02 X45 Z-35 I5 P0030

N0110 G01 X56 E1.2 P0040

N0111 X60 Z-37 E0.8 P0050

N0112 Z-60 P0060

N0113 X100 E1.2 P0070

N0114 G40

N0115 G80

N0116 G97 S884 P0060

N0117 G00 X800 Z1000 T0100

N0118 M05 M09 P0070

N0005 G14

N0006 P0020

N0007 G00 X800 Z1000

N0008 G50 S2000

N0200 G14

NBT01

N0201 G97 S884 M42 M03 M08 P0030

N0202 G00 X108 Z4 T010101

N0203 G96 G110 S300 P0040

N0204 G85 N0205 D3 F0.8 U0.4 W0.2 P0050

N0205 G81

N0206 G00 X35

N0207 G01 Z0 G42 E0.8 P0010

N0208 Z-30 P0020

N0209 G02 X45 Z-35 I5 P0030

N0210 G01 X56 E1.2 P0040

N0211 X60 Z-37 E0.8 P0050

N0212 Z-60 P0060

N0213 X100 E1.2 P0070

N0214 G40

N0215 G80

N0216 G97 S884 P0060

N0217 G00 X800 Z1000 T0100

N0218 M05 M09 P0070

N0219 M02

 

Milling tools or turning tools mini turret tools and double tools can be any number

[Bruce Caulley]

Thanks for the replies. I was thinking more about how they were named for loading purposes rather than programming.

 

I am fleshing out the requirements for a turn-key at the moment, but have not personally used one of these machines before and may not even be on the same continent if and when it is commissioned. On any tooling list I specify I need to say where and what each tool is doing.

 

Simple example:

I need a cnmg in the first station in the lower turning turret, a facemill in "pot 1" of the carousel, and in "pot 2" of the carousel I have a dual turning tool holder with a VNMG on one side and a parting blade in the other.

 

Assume for a second that I only have one spindle so am only working from one direction.

 

Ron,

I am only vaguely familiar with the mazatrol lettering system, but without putting you to too much trouble any explanation of the above scenario would be great.

 

Greg,

Is that T010101 describing tool 1, offset 1, position 1? So my combo tool above would be T020201 for the VNMG and T020?0? for the part off using G13? On the lower the cnmg would be T0101 using G14. What about the milling tool? Is that still called with T1 in G13 and then the offset applied with G41 and G43 as standard?

 

Sounds like these machines have a $hitload of offsets as standard.

 

Am I on the right track?

 

Bruce

[Greg Williams]

Bruce,

 

Just to clarify the above code is from a dual saddle standard turret machine, Sorry bout that

 

On a Macturn we have,

 

N0100 G13

N0101 G140

NA001

N0102 P0020

N0103 G20 HP=4

N0104 MT=00101

N0105 M321

N0106 VLMON[1]=9

N0107 G97 S683 M41 M04

N0108 G20 HP=4

N0109 TL=001001 BA=45 M603

N0110 G00 X170

N0111 Z6

N0112 X130.4

 

so here we have tool 1 offset 1 it is a 500 offset machine hence 3 digit tool numbers

 

BA=45 B axis angle for the turning op

M603 Base offset B - Milling spindle at 180 Degrees

 

By default there are 2 base offsets A - M602 and B - M603.

 

These base positions are 180 degrees apart. There is also the option to have 8 base postions so we can use a mini turret tool that contains 8 tools

 

This would be described as eg: position 3

TL=03001001 BA=45 M603

 

so to go back a little for a double turning tool

 

CNMG is TL=001001 BA=45 M603 - Tool 1 offset 1

VNMG is TL=001101 BA=45 M602 - Tool 1 offset 101

 

Sub spindle operations have exactly the same offsets. except there will be a G141 in the program

 

G140 = Main

G141 = Sub

The same program will make the same part on the sub as the main with the change of G140 to G141

 

Now for the Bottom turret it works exactly like a normal turret lathe

 

N0303 G00 Z6 T001001

N0304 X128

N0305 Z5.4

N0306 G96 G110 S280 P0050

N0307 G85 NL003 D5 F1.4 M85 P0060

NL003 G83

N0308 G01 X20.4

 

Here we have tool 1 offset 1

 

so we can have 2 off tool #1

 

If ya need a better explanation give me a call

[Greg Williams]

quote:

---

Simple example:

I need a cnmg in the first station in the lower turning turret, a facemill in "pot 1" of the carousel, and in "pot 2" of the carousel I have a dual turning tool holder with a VNMG on one side and a parting blade in the

---

To answer your question

 

Lower main spindle

G14

G140

T001001

 

Upper main spindle

G13

MT=00101 ---- Call the tool

M321 ------------ Change tool

TL=001001

 

G13

MT=00201

M321

G0 Y-20 ---- If ya need to

TL=001001 BA=? M602 ------ VNMG

 

Other side

 

TL=001002 BA=? M603 ----- Part Blade

[Bruce Caulley]