Single Tool - Missing T# M6

[PMDc]

I have a couple X5 posts derived from Mpmaster that will not post an M6 when the file has only one tool. Has anyone seen this before?

 

Thanks,

 

-Pat

[K2csq7]

On the tool branch of each of the operations parameters, check the box for "force tool change"

[PMDc]

On the tool branch of each of the operations parameters, check the box for "force tool change"

 

 

Thanks for the reply. However this did not solve the problem. When I use a Mastercam supplied post it's there but the custom post I was given does not.

 

I'll keep searching or revise a "good" post to get what I need.

 

 

Thanks again.

[Guest]

The easist thing to do would be this but somehow I suspect this is going to cause another as yet either unthought of or unasked question

in the ptlchg_com section

 

#if stagetool >= zero,
     #  [
     #  if omitseq$ = 1 & tseqno > 0,
     #    [
     #    if tseqno = 2, n$ = t$
     #    pbld, *n$, *t$, "M06", ptoolcomm, e$
     #    ]
     #  else, pbld, n$, *t$, "M06", ptoolcomm, e$
     #  ]
     pbld, n$, *t$, "M06", ptoolcomm, e$

[nathaninc]

help im having the same trouble: two ops, one tool, M00 after 1st op w/ force tool change

i need a tool change in the first op (force tool change didnt work in first op)

 

%

(PROGRAM NAME - 2701 )

(DATE=DD-MM-YY - 29-06-12 TIME=HH:MM - 07:54 )

N100 G0 G17 G40 G49 G80 G90

( 1 CHAMFER MILL TOOL - 2 DIA. OFF. - 2 LEN. - 2 DIA. - 1. )

G0 G90 G54 X12.52 Y-3.06 S9000 M3

G43 H2 Z.5 M8

Z.1

G1 Z-.28 F30.

G41 D2 X10.02 F80.

G0 Z.5

X10.4013 Y.06

Z.1

G1 Z-.28 F30.

X14.1513 F80.

G0 Z.5

X22.21 Y0.

Z.1

G1 Z-.25 F30.

Y-3. F80.

G0 Z.5

X-.06

Z.1

G1 Z-.25 F30.

Y0. F80.

G0 Z.5

G40 M5

G91 G28 Z0. M9

G28 X0. Y0.

M01

( 1 CHAMFER MILL TOOL - 2 DIA. OFF. - 2 LEN. - 2 DIA. - 1. )

N110 ( FLIP )

G0 G17 G40 G49 G80 G90

G91 G28 Z0.

G28 X0. Y0.

T2 T0 M6

G0 G90 G54 X14.1513 Y-3.06 S9000 M3

G43 H2 Z.5 M8

Z.1

G1 Z-.28 F30.

G41 D2 X10.4013 F80.

G0 Z.5

X10.02 Y.06

Z.1

G1 Z-.28 F30.

X12.52 F80.

G0 Z.5

X22.21 Y0.

Z.1

G1 Z-.25 F30.

Y-3. F80.

G0 Z.5

G40 M5

G91 G28 Z0. M9

G28 X0. Y0.

M30

%

 

*********************portion of post. see any reason y

 

Start of File and Toolchange Setup

# --------------------------------------------------------------------------

psof0$ #Start of file for tool zero

psof$

 

psof$ #Start of file for non-zero tool number

pcuttype

toolchng = one

if ntools$ = one,

[

#skip single tool outputs, stagetool must be on

stagetool = m_one

!next_tool$

]

"%", e$

"(PROGRAM NAME - ", sprogname$, ")", e$

"(DATE=DD-MM-YY - ", date$, " TIME=HH:MM - ", time$, ")", e$

pbld, n$, *sgcode, *sgplane, "G40", "G49", "G80", *sgabsinc, e$

sav_absinc = absinc$

if mi1$ <= one, #Work coordinate system

[

absinc$ = one

, sgabsinc, *sg28ref, "Z0.", e$

, *sg28ref, "X0.", "Y0.", e$

absinc$ = sav_absinc

]

pcom_moveb

c_mmlt$ #Multiple tool subprogram call

ptoolcomment

comment$

pcan

if stagetool >= zero, pbld, *t$, "T0 M6", e$

pindex

if mi1$ > one, absinc$ = zero

pcan1, pbld, *sgcode, *sgabsinc, pwcs, pfxout, pfyout,

pfcout, *speed, *spindle, pgear, strcantext, e$

pbld, "G43", *tlngno$, pfzout, scoolant, next_tool$, e$

absinc$ = sav_absinc

pcom_movea

toolchng = zero

c_msng$ #Single tool subprogram call

 

ptlchg0$ #Call from NCI null tool change (tool number repeats)

pcuttype

pcom_moveb

c_mmlt$ #Multiple tool subprogram call

if counter <> 1,

[

pbld, comment$

#"G43", "H27", pfzout, "M08", e$

]

counter = 0

comment$

pcan

result = newfs(15, feed) #Reset the output format for 'feed'

pbld, sgplane, e$

pspindchng

pbld, scoolant, e$

if mi1$ > one & workofs$ <> prv_workofs$,

[

sav_absinc = absinc$

absinc$ = zero

pbld, sgabsinc, pwcs, pfxout, pfyout, pfzout, pfcout, e$

pe_inc_calc

ps_inc_calc

absinc$ = sav_absinc

]

if cuttype = zero, ppos_cax_lin

if gcode$ = one, plinout

else, prapidout

pcom_movea

c_msng$ #Single tool subprogram call

 

ptlchg$ #Tool change

pcuttype

toolchng = one

if mi1$ = one, #Work coordinate system

[

pfbld, *sg28ref,"X0.","Y0.", e$

pfbld, "G92", *xh$, *yh$, *zh$, e$

]

pbld, "M01", e$

pcom_moveb

c_mmlt$ #Multiple tool subprogram call

ptoolcomment

pbld, n$, comment$

pbld, *sgcode, *sgplane, "G40", "G49", "G80", *sgabsinc, e$

"G91 G28 Z0.",e$

"G28 X0. Y0.",e$

pcan

result = newfs(15, feed) #Reset the output format for 'feed'

pbld, *t$, "T0 M6", e$

pindex

sav_absinc = absinc$

if mi1$ > one, absinc$ = zero

pcan1, pbld, *sgcode, *sgabsinc, pwcs, pfxout, pfyout,

pfcout, *speed, *spindle, pgear, strcantext, e$

pbld, "G43", *tlngno$, pfzout, scoolant, next_tool$, e$

absinc$ = sav_absinc

pcom_movea

toolchng = zero

c_msng$ #Single tool subprogram call

 

pretract #End of tool path, toolchange

sav_absinc = absinc$

absinc$ = one

sav_coolant = coolant$

coolant$ = zero

#cc_pos is reset in the toolchange here

cc_pos$ = zero

gcode$ = zero

pbld, sccomp, *sm05, psub_end_mny, e$

pbld, sgabsinc, sgcode, *sg28ref, "Z0.", scoolant, e$

pbld, *sg28ref, "X0." ,"Y0.", protretinc, e$

absinc$ = sav_absinc

coolant$ = sav_coolant

 

pretracteof

sav_absinc = absinc$

absinc$ = one

sav_coolant = coolant$

coolant$ = zero

#cc_pos is reset in the toolchange here

cc_pos$ = zero

gcode$ = zero

pbld, sccomp, *sm05, psub_end_mny, e$

pbld, sgabsinc, sgcode, *sg28ref, "Z0.", scoolant, e$

pbld, *sg28ref,"X0.", "Y0.", protretinc, e$

absinc$ = sav_absinc

coolant$ = sav_coolant

 

protretinc #Reset the C axis revolution counter

if frc_cinit & rot_on_x,

[

rev = zero

sav_rev = zero

cabs = zero

csav = zero

indx_out = zero

if index, e$, pindxcalc, pindex

else, *cabs

prvcabs = zero

!csav, !cabs

]

[Guest]

Change this line

 

if stagetool >= zero, pbld, *t$, "T0 M6", e$

 

to this

 

pbld, *t$, "T0 M6", e$

 

It looks like you're outputting everything as T0, so I don't know exactly what you have got going on there but swapping that code around a s noted about will get you a tool output