Work offset keep rolling up on A move.

[tnguyen65]

Could any one look at my file, and tell me why the work offset keep rolling up on A move.

 

Thanks

TT.Z2G

[MSL]

I can't see your file now but make sure you force 0 instead of -1 in your work offset.

[tnguyen65]

I can't see your file now but make sure you force 0 instead of -1 in your work offset.

I tried it, but it still post out the same. Could anyone look at my post and tell me what is wrong?

[crazy^millman]

For all operations you are posting do you have 0 for the workoffset? Are you doing a transform operation and have checked maintain workoffset? Sorry on my IPAD so cannot look at the file.

[tnguyen65]

For all operations you are posting do you have 0 for the workoffset? Are you doing a transform operation and have checked maintain workoffset? Sorry on my IPAD so cannot look at the file.

Yes, I try all of it. I believe my post is the problem. I must had the setting wrong in my post

[Dave Allen]

Yes when I first tried your program I got multiple work offsets but as MSL and  ron said I changed the work offset to 0 instead of -1 and all was good.

I did get an error log running your post but didn't have time to check it out, maybe tomorrow I'll have a chance to take a look.

[Guest]

This section of you post  has been altered....and it is not correct

 

variables being called that are not defined

pwcs            #G54+ coordinate setting at toolchange
      if wkofs = m_one, wkofs = zero
      if sub_trnstyp$ < zero, workofs$ = wkofs
      if hard_mi1 > one,
        [
        sav_frc_wcs = force_wcs
        if sub_level$ > 0, force_wcs = zero
        if workofs$ <> prv_workofs$ | (force_wcs & toolchng),
          [
          if workofs$ < 6,
            [
            g_wcs = workofs$ + 54
            *g_wcs
            ]
          else,
            [
            p_wcs = workofs$ - five
            "G54.1", *p_wcs
            ]
          ]
        force_wcs = sav_frc_wcs
        !workofs$
        ]

On  top of that it's an old post

 

 

 Executable          : MP v9.0

 

Even with the errors in your post it will post properly if you set it right

 

 

%

O0000

(P/N)

(CUSTOMER)

(OP# )

(SETUPDESC)

 

(X0=)

(Y0=)

(Z0=)

(A0=)

 

N1T1( 3/8 BULL ENDMILL 0.125 RAD)

N2M6

N3G40G80G17

N4G0G90G54X0.Y-.4775A0.

N5S4074M3

N6G43H1Z.25

N7Z.2

N8G1Z-.5388F12.06

N9Y-.4375F24.12

N10X-2.

N11Z-.3388F12.06

N12G0Z.25

N13A-90.

N14X0.Y-1.9775Z1.75

N15Z1.7

N16G1Z.9612

N17Y-1.9375F24.12

N18X-2.

N19Z1.1612F12.06

N20G0Z1.75

N21A-180.

N22X0.Y-.4775Z3.25

N23Z3.2

N24G1Z2.4612

N25Y-.4375F24.12

N26X-2.

N27Z2.6612F12.06

N28G0Z3.25

N29A-270.

N30X0.Y1.0225Z1.75

N31Z1.7

N32G1Z.9612

N33Y1.0625F24.12

N34X-2.

N35Z1.1612F12.06

N36G0Z1.75

N37G91G28Z0M5

N38M30

%

 

 

 

Check the work offset settings in the file and seriously considering using a newer post processor

JP_TT.zip

[tnguyen65]

Could you tell me, what  I need to fix it?

I know it an old post, but it has some setting in there that I want.

 

Thanks

[crazy^millman]

Could you tell me, what  I need to fix it?

I know it an old post, but it has some setting in there that I want.

 

Thanks

 

 

They used your post and once they changed the operations everything came out like it should. That means it is not a post issue so what can someone tell you to change to make work correctly in the post when the again the post is not the issue here?

[tnguyen65]

They used your post and once they changed the operations everything came out like it should. That means it is not a post issue so what can someone tell you to change to make work correctly in the post when the again the post is not the issue here?

My mistake, I thought JParis point out the section of my post is incorrect.