Custom drill cycle w/M70

[savagkd]

Hi all,

 

I'm trying to create my first custom drill cycle and could use some help.

 

This is for a 5 axis head/head router with a pneumatic peck head, MCamX9, Fanuc 5 axis router post.

 

In a 5 axis drill toolpath with lots of holes, how do I get an M70 after each of the XYZBC moves?

 

I've got the Control Def, Mill Drill Cycles, drill cycle 9 set up for the "Air Peck", but can't figure out the danged M70. Is this MD/CD or post?

 

 

Thanks

[crazy^millman]

I think it would best to handle this in the post. Maybe someone knows a better different way with MD/CD that I am not aware of, but you have got pretty much got it right there. Look here and add what you need and should be good. Something simple can be done or you can use a mi or mr trigger. Cantext could be done, but think it is more trouble than it is worth.

pdrlcst_2$       #Custom drill cycles 8 - 19, additional points (user option)     
      #Use this postblock to customize drilling cycles 8 - 19
      pdrlcommonb
      "CUSTOMIZABLE DRILL CYCLE ", prdrlout, e$
      pcom_movea

The 1st pdrlcst is for the 1st line f a canned cycle. The 2nd one is for the additional places the canned cycle needs to work with the tool. Once you have done a couple custom drill cycles in Mastercam the sky is pretty much the limit with what you can do with them.

 

HTH

[savagkd]

Worked perfectly.

 

pdrlcst$ #Custom drill cycles 8 - 19 (user option)

#Use this postblock to customize drilling cycles 8 - 19

pdrlcommonb

prdrlout, e$ #"CUSTOMIZABLE DRILL CYCLE "

"M70", e$

pcom_movea

 

pdrlcst_2$ #Custom drill cycles 8 - 19, additional points (user option)

#Use this postblock to customize drilling cycles 8 - 19

pdrlcommonb

prdrlout, e$ #"CUSTOMIZABLE DRILL CYCLE "

"M70", e$

pcom_movea

 

Thanks Ron!!!