Post help, please.

[ScottyB]

Upon running my v8 Heian post through the v9 update, I now get the following text (as in lines 125, 135), which gives an alarm. Any ideas as to where this is coming from and how to stop it?

 

N110 G90

N115 S15 M03

N120 M06T1

N125 tool10

N130 M13

N135 tool10

N140 M11

N145 G55 G0 X-39.76 Y-31.844

N150 G64 G43 H1 Z.25

N155 G0 Z.1

 

Thanks,

ScottyB stumped.

[Rekd™]

Turn on debugging and re-post, it will tell you where in the post a line comes from.

 

'Rekd

[ScottyB]

Not to sound dumb here Rekd, but where do I find the debug switch. I thought it would be on the Update screen, but maybe not.

Kin ya give me a hint?

 

ScottyB. lookin everywhere.

[Rekd™]

Scotty, Open your post in your favorite editor, look for this: and change the fastmode and bug 2 to what I have. Remember what you change them from, and always back up your posts before editing.

 

code:

---

 # --------------------------------------------------------------------------

# Debugging and Factory Set Program Switches

# --------------------------------------------------------------------------

fastmode : 0 #Posting speed optimizition

bug2 : 40 #Append postline labels, non-zero is column position?

---

'Rekd

[CAM Disciple]

Open up your post and try use search and enter tool10 as your search string.

 

It might be just a simple typo error.

 

Look for something that's simple and easier to solve before you went all the troubles.

 

Let us know your problem and we will help you

[ScottyB]

This is the only place that "tool10" appears.

 

'Rekd, I found "bug 2", but I didn't find the other line.

I'm learning a lot about posts though.

 

sd05 M13 # M code for head number 5

sd06 M13 # M code for head number 6

sd07 M13 # M code for head number 7

sd08 M13 # M code for head number 8

sd09 M13 # M code for head number 9

sd10 tool10 # M code for head number 10

 

sd11 tool11 # M code for head number 11

 

sd12 tool12 # M code for head number 12

 

sd13 tool13 # M code for head number 13

 

sd14 tool14 # M code for head number 14

 

sd15 tool15 # M code for head number 15

 

ideas?

 

Thanks

[ScottyB]

These are the results of the post.N110 G90 psof

N115 S15 M03 psof

N120 M06T1 psof pheadcode1

N125 tool10 psof phead0

N130 M13 psof phdown1

N135 tool10 psof pdown0

N140 M11 psof psupp1

N145 G55 G0 X-37.76 Y-41.5244 psof

 

If that helps.

[Jim Evans from CNC Software]

ScottyB,

 

If you look right below this string table, there should be a line that that starts with fstrsel and looks something like this

 

fstrsel string1 variable string2

 

This line has 4 variables. the first being fstrsel (MP function), the second should be the string variable of the first string in the table. The third is the selector variable (variable with the value) and the last one being the target string (string variable used on output line).

 

One of two things is happening. The selector variable's value is such that the string tool10 is output from the list. The other possibility is that the string sd10 is on an output line. You can search the post for sd10 and you should only find one, which is the one shown in your string table.

 

If you contact your dealer and send them your post and MC9 file I'm sure they can figure it out very quickly. Without these files, I'm just guessing.

[CAM Disciple]

When you declare a variable call var1 and you see the string "var1" in your program, that usually means you didn't format the variable properly.

 

I can't help you without seeing your post. I am just guessing here and I might be wrong. You can upload your post to the ftp site if this is possible.

 

Based on your description:

quote:

---

N125 tool10 psof phead0

N130 M13 psof phdown1

N135 tool10 psof pdown0

---

I am betting that you have something like

sd10 in your psof or phead0 post block which call out the sd10 variable and thus posting tool10. So, try look into how you declare and format the sd10 variable. Try find out you have the right fstrsel.