T rouble with Fadal post

[KJS]

We just bought a remanufactured Fadal VMC and the program is giving us trouble. When we post the first line of the program looks like this:

N1 o0000(file name)

The trouble is we have to go in every time and change the letter o to a 0 like the other four 0's.

A little farther down in the program we get a E1 for the fixture offset which is fine but sometimes we get an E0 instead which we again have to edit.

How can this be corrected? Do we have to edit the post, which I've never done. Do we need to get a different Fadal post from the dealar.

(Both of our current Fadal post give us the same problem) Or is there some other way to fix this?

Thanks in advance for any help!

[Mike Whitten CAD/CAM Contractors]

The first thing I would do is to ask your dealer to get the latest mpmaster Fadal post for you.

 

That is what I did. I believe that is was very close to perfect from the begining. I only had to add a few minor customizations that were specific to our preference.

 

Mike

[KJS]

One glitch I forgot to mention was that when we drill, it always skips the first drill hole. If we're only drilling one hole it doesn't drill any if we're drillig ten holes it skips the first and drills the other nine.

[Phil Orenstein]

The Fadal control has an option to read std fanuc based programs in which case the MPfan.pst works like a charm. I don't recall if its called 'format 1' or 'format 2'. You may be able to set your control to either mode. It was set up for fanuc at a shop where I recently worked. It read the typical g54's, G43 etc. HTH

 

Phil

[Keith Graydon]

+1 Phil,( format 2) or use Mpfadal.pst straight off the MCam CD

[KJS]

Thanks for the responses guys but it still isn't working. It won't recieve a program in format 2. When I put it in format 2 I get an error that says wrong O-word. This happens using the mpfan post. The mpfadal.pst is what we've been trying all the while without luck.

[Rekd™]

The O-word must be an oh, not a zero. The line BEFORE it it must contain a % and only a %.

 

code:

---

%

O0001

(Your Program Here)

M2

%

---

'Rekd

[Keith Graydon]

O

[KJS]

Thanks for the help. We got the latest post from our dealer and that cleared up the problems. Now the only glitch is the first line of our program reads 09999. The program name doesn't appear untill line 3 so the machine thinks the program name is 9999. Since we can't save every program as 9999, how do we get it to read the real file name on line 3?

[Keith Graydon]

type in an appropriate # in the "Program #" field on the toolpath parameters page.

[crazy^millman]

You may need a post mod to get the program name on the same line as the program number. Here is what I have done for the MPMASTER_FADAL post. I have always output 9999 if no program is used. We dnc 99% of our programs so no big deal if they have the same number.

code:

---

pheader         #Call before start of file                         

if met_tool = one, #Metric constants and variable adjustments

[

ltol = ltol_m

vtol = vtol_m

maxfeedpm = maxfeedpm_m

]

result = nwadrs(srotary, cabs)

result = nwadrs(srotary, cinc)

result = nwadrs(srotary, cout)

strc = srotary

scminus = srotary + sdash

result = nwadrs(srotary, indx_out)

 

"%", e

spaces=0

if progno = 0,

[

progno = 9999

]

*progno, " (", sprogname, ")", e

---

I hope that helps.

[Mike Mattera - TFM]

Kevin,

 

Keith is right. Put in a progran munber in the Tool Parameter page and you'll get that number. If no number is entered you get 9999.

 

You can also call me for help.

 

Mike Mattera

[KJS]

To all who helped I want to say Thank You! Our MC dealer is Mike Mattera from Shopware Inc. He deserves a Thank You for the help as well as the very quick response time sending me a new post. Thanks again.