Osp7000 lathe coolant issues

[mkd]

Any okuma macturn gurus know why the control refuses to activate coolant for lathe tools? Mill tools: no problem.

Correction; tried again tonight and no stick tools are getting coolant after a tool change. Initial power up: coolant works.

Also how do you activate a concept 2000 conveyor and drum screen flush via the CNC?
humble thanks in advance

edit: gosiger hooked me up: M244 on, M243 off.

[jeff]

Are you using 2 different pumps? The reason I ask is maybe one of the pumps blew the relay in the back? 

Is that pump turning on?

[mkd]

Using one pump for coolant to the turret. Valving changes from the mill side to the turning side. The pump doesn't come on for the lathe side. Leave the manual button illuminated while indexing over to the mill side and coolant sperts out on the lathe side briefly before switching to the mill side.

Gotta be something simple\ stupid I'm missing

[mkd]

Using mt=xx01, m321 for the tool change and T100 ba=x.x for angle index in mdi. Is there some other method to signify lathe tools?

 

T300 for mill side

[The Cathedral]

On our Macturns/Multus, there are different codes for mill tools and lathe tools, all depending on how the tool is defined in the control. I'm not sure about the control you have as our controls are OSP100, 200, and 300.

The BA only sets the angle of the head, it doesn't do anything else. When you define a tool in the control, you have to set its type, shape, and default orientation. It's the type of tool you call it that defines what coolant works. Mill tools can be set as lathe tools, lathe tools can NOT be set as mill tools.

 

Thru spindle coolant; Lathe tool: M08/M09, Mill tool: M174/M175.
Flood coolant (Turret nozzles); Lathe coolant 3: M262/M263, Mill tool: M08/M09.

[mkd]

Ok, page the shows tool\pots numbers also has an entry for T or M tool to limit which side of the turret it can be loaded. Maybe it is in the geometry page that shows graphic of general tool shape and orientation. There are no coolant options there but maybe I need to play around with settings here?

[The Cathedral]

You don't set the coolant options, just the tool type. Then OSP knows what coolant codes to use with that tool. We set ours in the ATC Tool Data page; but again, ours is a much newer control so it is probably different.

[mkd]

Tried a couple of variations last week: od tool and now id groove. No m262 on 7000.

I'll throw a g136 at it out of utter desperation tonight after my 12hr shift.

Documentation and quirks sure make me wish it was a Haas.

[chris m]

 

 

Documentation and quirks sure make me wish it was a Haas

 

HAHAHAHAHAHAHAHA...that is some funny sh!t

 

Does the Okuma store offer no help?

[mkd]

Well I totally stumped gosiger on how to turn on the mayfran concept 2000 conveyor and they finally stopped replying to my dumb questions. They also only had b axis alignment instructions for a much newer control. Parameters on the 7000 don't have english names like newer controls. So I'm pretty lost.

 

Funny quirks

Tool.setter throws and alarm on every tool unless I index the B away and back to zero. No explination in any manual I've seen.

[mkd]

Either I'm an idiot or this machine is quirky. Don't answer that.

 

Mdi:

MT=5801

M321

no coolant working

 

MT=5801

M321

T100

WORKS!!!!

 

then change tools

Mt=3201

m321

No coolant

Mdi T100

Working again.

 

Not in the manual.

 

Going to see if Haas will come out and take a look at it.

 

[The Cathedral]

Ah. I do not think you are programming that correctly.

 

The MT code is a pre call; you use it to stage the next tool to be used, not to call up the tool you are about to use. Using it like you are doing is not calling up any tool offset or information, it it merely cycling the tool into position in the ATC. You need a tool activation command (on our Macturns, it's TL, on our Multus it's TD).

 

You are sort-of activating it with the dummy "T100" command, but all you're doing is calling up the information for tool 100, not the tool you are using.

 

For example, this is how we program, assuming tool 21 is already in the spindle:

 

N21 (.4375 REAMER)
TL=2121BT=1
MT=0701
M110
M13SB=836
M8M175(M175=THROUGH THE TOOL COOLANT ON)
G00 X 50.     Z  1.520
G00 X  3.000
G138(Y-MODE)
G00 X  0.550            Y 0.031
G94
G181X -0.650  Z  1.520  Y 0.031 C 0. I 0. F 6.688
G180
M12(STOP MILLING SPINDLE)
M146(UNCLAMP C-AXIS)
G136(CANCEL Y-MODE)
M109(CANCEL MILLING MODE)
G00 X   50.              M09
M174
G21HP=4
M321(PUT TOOL #07 INTO SPINDLE)

[mkd]

Thanks a bunch. I'll be using your posted excerpt as a reference. I can use the pre stage as in your example. reminder that i have to get my post guy to add that in.

My posted code has the TL, my confusion was just futzing with the machine in MDI it's just weird the control gurus decided to throw up this roadblock only for lathe tools.

How do you activate your chip conveyor, m278? Day job's mu1000 uses that IIRC. Opening the control box and tripping the relays is no bueno.

[Greg Williams]

this should work

 

G140
G138
G00Y0
G136
(MCX FILE  - C:\DATA\MASTERCAM\MASTERCAM SAMPLES\MACTURN_SAMPLE.MCX-8)
(POST      - MPPOSTABILITY_OKUMA_MACTURN_30W.pst)
(PROGRAM   - TURNING-1C.min)
(DATE      - 2015.01.30)
(TIME      - 10:14 AM)
(T1   - DCMNN 2525M 09 - R08 - R1.200mm)
(T3   - ID FINISH MIN. 32. DIA. - 55 DEG. - R1.200mm)

G140
G50 S1000
(VZOFZ = )
(VZOFC = )

G141
G50 S1000
(VZOFZ = )
(VZOFC = )

DRAW
G140
G00 W1500.
G20 HP=4
G140
G50 S=600
N1
(ROUGH OD)
G140
MT=00101 (DCMNN 2525M 09 - R08)
M321
NA1 (RESTART POSITION)
G20 HP=4
G50 S=600
G94 M41 M602 BA=45. TL=010101
G18
MT=00303
G00 X420. Z35.
G96 S=295
M04
Z17.736
X409.257
G95 G01 X402.185 Z14.2 F.3
Z-240.2
X409.257 Z-236.664
G00 Z17.736
X403.442
G01 X396.371 Z14.2 F.3
Z-205.743
G03 X397.2 Z-208.185 L7.4
G01 Z-245.2
X404.271 Z-241.664
G00 Z17.736
X397.627
G01 X390.556 Z14.2 F.3
Z-201.798
X392.865 Z-202.952
G03 X397.2 Z-208.185 L7.4
G01 X404.271 Z-204.649
G00 Z17.736
X391.813
G01 X384.742 Z14.2 F.3
Z-198.891
X392.865 Z-202.952
G03 X397.2 Z-208.185 L7.4
G01 X404.271 Z-204.649
G00 Z17.736
X385.998
G01 X378.927 Z14.2 F.3
Z-195.968
G02 X379.615 Z-196.327 L11.1
G01 X392.865 Z-202.952
G03 X394.742 Z-204.101 L7.4
G01 X401.813 Z-200.565
G00 Z17.736
X380.184
G01 X373.113 Z14.2 F.3
Z11.
Z-188.539
G02 X379.615 Z-196.327 L11.1
G01 X388.927 Z-200.983
X395.998 Z-197.448
G00 X420.
Z35.
M05
X2000.
G20 HP=4
M01

N2
(ROUGH BORE)
G140
MT=00303 (ID FINISH MIN. 32. DIA. - 55 DEG.)
M321
NA3 (RESTART POSITION)
G20 HP=4
G50 S=600
G94 M41 M602 BA=0. TL=030303
G18
G00 X300. Z30.
G96 S=310
M03
X291.862
Z4.7
G95 G01 Z2.7 F.3
Z-174.526
X287.
X284.172 Z-173.112
G00 Z4.7
X296.724
G01 Z2.7 F.3
Z-174.526
X291.462
X288.633 Z-173.112
G00 Z4.7
X301.586
G01 Z2.7 F.3
Z-9.48
G02 X299.6 Z-13.182 L7.4
G01 Z-20.103
Z-50.036
Z-58.934
Z-74.934
Z-174.526
X296.324
X293.495 Z-173.112
G00 Z4.7
X306.448
G01 Z2.7 F.3
Z-6.941
G02 X301.186 Z-9.85 L7.4
G01 X298.357 Z-8.436
G00 Z4.7
X311.31
G01 Z2.7 F.3
Z-5.881
X309.478 Z-6.204
G02 X306.048 Z-7.074 L7.4
G01 X303.219 Z-5.659
G00 Z4.7
X316.171
G01 Z2.7 F.3
Z-5.023
X310.91 Z-5.951
X308.081 Z-4.537
G00 Z4.7
X321.033
G01 Z2.7 F.3
Z-4.166
X315.771 Z-5.094
X312.943 Z-3.68
G00 Z4.7
X325.895
G01 Z2.7 F.3
Z-3.309
X320.633 Z-4.237
X317.805 Z-2.822
G00 Z4.7
X330.757
G01 Z2.7 F.3
Z-2.452
X325.495 Z-3.379
X322.667 Z-1.965
G00 Z4.7
X335.619
G01 Z2.7 F.3
Z-1.594
X330.357 Z-2.522
X327.529 Z-1.108
G00 Z4.7
X340.481
G01 Z2.7 F.3
Z-.737
X335.219 Z-1.665
X332.391 Z-.251
G00 Z4.7
X345.343
G01 Z2.7 F.3
Z.12
X340.081 Z-.808
X337.253 Z.607
G00 X300.
Z30.
G97 S=338 M03
M05
X2000.
G20 HP=4
TL=003000 BT=0 BA=90.
M02

[mkd]

 

Finding some off the shelf (bt40) boring bar holders would be nice. Rolling your own is kinda a pita.

 

Gonna have to try that M602 tonight. Not in any of the manuals

 

[Greg Williams]

Also try the offset codes

 

for a 500 offset machine TL=01012022 for Edge 1 tool 12 offset 22

for a 96 offset machine TL=030122 for edge 3 tool 1 offset 22

[mkd]

This okuma neophyte thanks you. just saved me 2 hrs of manual reading.and head scratching.

M602 just threw an alarm. Must need to get a service tech in to figure out the configuration.

[The Cathedral]

M602 only works with HSK or Capto spindles. If you don't use those, it doesn't work.

[mkd]

new issue that applications hasn't been able to help

solve yet:

I'm having trouble getting Turret Comp to work at BA=90. on this macturn30.

tool is missing the correct dimension by .077 on X and .021 on Z (programed with g127 so .077 error on tip of EM and .021 dia)

works fine at B0, as the tool setter helps compensate for errors.

this instruction sheet is nice but gives you no clue where or how to enter values in sys param page 9