Jump to content

Welcome to eMastercam.com
Register now to gain access to all of our features. Once registered and logged in, you will be able to create topics, post replies to existing threads, give reputation to your fellow members, get your own private messenger, post status updates, manage your profile and so much more. This message will be removed once you have signed in.
Login to Account Create an Account
Photo

Tap G code- Fanuc 10T

- - - - -

  • Please log in to reply
6 replies to this topic

#1
cormigu

cormigu

    Member

  • Members
  • PipPip
  • 119 posts
Hi Guys,
I need to make a 6-32 Tap hole,but I don't know the code line(G code).

Please help...:(

#2
Russh67

Russh67

    Member

  • Members
  • PipPip
  • 78 posts
  • Location:Long Island, New York
lathes are tricky

rigid tapping this may help.

O0018
T0606
G0X0.Z.1M08
M29 (may or may not need this)
G84 Z-.975 R0.1 F.03125 S600 M03 (Rigid tap Cycle)
G0Z.1M09
G80
G28 U0 W0.
M5
M30

Note per feed per rev feed is pitch of 6-32.
  • Del. likes this

#3
strabe

strabe

    Advanced Member

  • Members
  • PipPipPip
  • 768 posts
It's been a while but I think it's G32 on Fanuc lathes.
  • Allan likes this

#4
Allan

Allan

    Advanced Member

  • In-House Solutions
  • PipPipPip
  • 807 posts
Yes G32/G33 is the ticket, you will not be able to rigid on a 10T, you'll need to use a floating tap holder.
Some machines will alow you to M04 without M05ing.

so it's like

G97 M03 S200
G00 X0. Z.25
G32 Z-.5 F.03125
M05
M04
G32 Z.25 F.03125
G00 X10. Z 5.
...

#5
Russh67

Russh67

    Member

  • Members
  • PipPip
  • 78 posts
  • Location:Long Island, New York
Cormigu:

I apologize for giving you bad information, those guys are right. I was wrong and stand corrected. Didn't read what you had close enough...My Bad :(
  • Del. likes this

#6
cormigu

cormigu

    Member

  • Members
  • PipPip
  • 119 posts
Thx Guys for help me,I figure out my program. it 's work fine.

NO.6-32 RH TAP)
N1020 G0 T0505
M08
N1030 G18
N1035
N1040 G97 S100 M03
N1050 G0 G54 X0. Z.25
N1060 Z.1
N1070 G99 G1 Z-.255 F0.03125

N1080 M05
N1090 G97 S100 M04
N1100 Z.25
N1110 M05
N1120 G97 S500 M03
N1130 G28 U0. W0.
N1140 G00 T0500
N1145 M01

#7
Allan

Allan

    Advanced Member

  • In-House Solutions
  • PipPipPip
  • 807 posts
You'll want to change that G01 to a G32 because the feed override is active on a G01 not a G32