rotating named views

[specv]

I need to rotate my part but I want all the named views to follow it so that my indexes are right, I am using a horizontal machine so wcs is always Top, so that needs to stay there. Is there anyway to do this without renaming everything and losing toolpath associativity?

[Ray H.]

ya use wcs Do NOT Rotate the part, not yellin' just emphasizing

[specv]

i need to rotate the part because the set-up changed on the machine and in order to verify this I need the fixture and part to be right.

[specv]

maybe James can weigh in on this one. I would like to use WCS more in depth, but now is not the time because this part is already programmed

[edmBosto]

SpecV

If you put a check at the operations you need to move you can then transform/rotate and then check

the box for"create new operations and geometry" and throw that geometry on another level.

 

Or just rotate the part and regenerate the toolpath.

 

Not quite sure if that's what your asking.

[brilu397]

You can rotate your top wcs to the new angle, and then change all your top wcs to the new wcs in each operation. Kinda of a pain if there are alot of ops, But the t/c planes will follow the new wcs and maintain there associativity to the geometry.

[Guest]

All I know is I never move a part once it is programmed.

 

I will create a new plane for toolpaths and change the plane in the tool parameters but the part stays still.

[88Matt]

i agree 100% with John.

Using wcs and your planes u should not have to move your part. ever. Especially with how muck easier it is in X (one of a few things).

IMHO.

[specv]

I usually never do either but the fixture changed and so did the orientation, mid-process, I figured it out though, i just had to change one plane at a time. It worked out.

[Craig-B]

You can try to change the common offset of the rotary on the machine depending on the control. I programmed a tombstone with 43 tool and 132 operatons and they change the setup of the fixture, to where the (B0.0) in my program would be (B90.0). So on my Fanuc I changed the common offset to 90.0 degrees ((G10G90L2P0X0.Y0.Z0.B90) and I didn't change any thing in Mastercam and the part ran perfect.

[specv]

FNMI we try not to do this as we have multiple jobs running of the same machine at the same time. Also if an operator looks at the screen and then the table ans freaks out and thinks somethings wrong possibly shutting a job down in the middle of the night when I'm not here.

[Rick Henrickson 65]

if you run your G10 lines with each program it shouldnt be a problem, the cell controler should handle this quite easily.