updating post for X2MR1

[DJG]

We just started using X2MR1 and the post isn't working properly, it was fine using X2 before the upgrade. Now it outputs 2 G91's on 1 line, there isn't a M3 or spindle speed.

 

Also the config files are read only, how are we to make changes if needed? Is this designed this way or do we have a problem with the software?

 

thanks,

Darren

mill3 X2MR1

[Guest]

You don't need to update your post, per se.

 

Just copy the machine/control defs and post to the appropriate MR1 directories.

 

When you open it up it should be all set

[DJG]

Thanks for your input John.

[Guy Arseneault]

John,

I updated to X2 MR1 SP1 and now my post spits out dollar signs. What you mentioned to Darren I idn't need to do. It was in it's proper place already. Any other reasons it could be or am I missing something?

 

quote:

---

You don't need to update your post, per se.

 

Just copy the machine/control defs and post to the appropriate MR1 directories.

 

When you open it up it should be all set

---

GETTING THIS

 

G17

G3X-.7488Y.2919i$ -.7488j$ .5419

 

SHOULD BE THIS

 

G17

G3X-.7488Y.2919I-.7488J.5419

[Guy Arseneault]

Bump: HELP

 

This is what got posted using the debugger.

 

G17

G3X-1.8158Y1.4812i$ -1.7825j$ 1.5341 pcir$ pcir$ 74.

G1X1.3176Y-.4911 plin$ plin$ 76.

G3X1.4037Y-.4715i$ 1.3508j$ -.4382 pcir$ pcir$ 78.

 

 

This from my post.

 

pcir$ # Circular interpolation

n$, sgplane,e$

if plane$ = 0, n$, sccomp, sgcode, *x$, *y$, z$, *i$, *j$, pfr,e$

if plane$ = 1, n$, sccomp, sgcode, x$, *y$, *z$, *i$, *k$, pfr,e$

if plane$ = 2, n$, sccomp, sgcode, *x$, y$, *z$, *i$, *k$, pfr,e$

 

 

I don't understand the reason for the dollar signs at the end of i and j and why the i and j are not capitilized in my posted program.

[Roger Martin from CNC Software]

What you see in the PCIR postblock in your PST looks OK.

 

As for the output...

If you see a variable name followed (only) by its numeric value, you are usually missing a format (FMT) assignment on those variable(s).

 

Like this -->

 

fmt I 2 i$ # Arc center description in X

fmt J 2 j$ # Arc center description in Y

fmt K 2 k$ # Arc center description in Z

 

*NOTE: 'fmt 2' may not be the correct format. It depends on how this format is defined via its Format Statement (FS) in your PST.

[Guy Arseneault]

Roger,

 

Here is how the post is set-up. Also I don't understand why it doesn't work correctly. I worked ok in X2.

 

 

# ------------------------------------------------------------------------

# Format Statements - i=incr., n=nonmodal, l=leave ldg., t=leave trlg

# d=delta, I=incremental

# ------------------------------------------------------------------------

fs 1 1.4 # abs, no lead 0, no trail 0, modal, 4 place decimal, use decimal

fs 2 2 0 # abs, no lead 0, no trail 0, modal, int, no decimal

fs 3 4 0 # abs, no lead 0, no trail 0, modal, int, no decimal

fs 4 1.2 # abs, no lead 0, no trail 0, modal, 2 place decimal, use decimal

fs 5 5 0 # abs, no lead 0, no trail 0, modal, int, no decimal

fs 6 1.4 # abs, no lead 0, no trail 0, modal, 4 place decimal, use decimal

# ------------------------------------------------------------------------

# Format Assignments

# fmt X 1 x - x, y, z, i, j, k, xh, yh, zh, xr, yr, zr

# are init. fs 1, with 'normal' prefix letter

# ------------------------------------------------------------------------

fmt N 5 n$ # Line number

fmt F 4 fr$ # Feedrate

fmt T 2 t$ # Tool number format

fmt M 2 cc$ # Cutter Comp.

fmt S 5 ss$ # Spindle Speed

fmt 2 plane$ # Modal plane code selector

fmt 2 gcode$ # Format linear G-code selector for modality only

fmt 2 ccomp$ # Modal format for ccomp

fmt 2 cs # Determine if canned shapes are used grs

fmt 2 ycs # Get canned shape number grs

[Roger Martin from CNC Software]

What 'fmt's are assigned to i$, j$, k$ ?

 

 

fmt I 2 i$ # Arc center description in X

fmt J 2 j$ # Arc center description in Y

fmt K 2 k$ # Arc center description in Z

[Guy Arseneault]

This is what I found Roger.

 

# Formulas - Use ':' instead of '=' to initialize variables

# ------------------------------------------------------------------------

skp_lead_flgs$ : 1 #Do NOT use v9 style contour flags

arctype$ : 1 # Arc center 1=abs, 2=inc, 3=st-cen, 4=unsigned inc.

do_full_arc$ : 0 #Allow full circle output? 0=no, 1=yes

helix_arc$ : 0 #Support helix arc output, 0=no, 1=all planes, 2=XY plane only

breakarcs$ : 0 #Break arcs, 0 = no, 1 = quadrants, 2 = 180deg. max arcs

 

gcode$ : -1 # Assure output of first G00

nobrk$ : no$ # Omit break of linear rapid?

omitseq$ : 1 # Omit sequence numbers?

progname$ : 1 #

spaces$ : 0 # omit spaces

seqmax$ : 9999 # Max. sequence no.

x$ : 999 # Initialize modals to force first output

y$ : 999

z$ : 999

i$ : 999

j$ : 999

k$ : 999

[Roger Martin from CNC Software]

If you don't have any fmt assigned to these variables in your PST, that is the reason for the NC output you are getting.

 

If this behavior started after running your PST thru UpDatePST, then check the current PST against the backup of the original PST that UpDatePST saved.

[Guy Arseneault]

This post ran fine in X2. I will check this post to the original I updated for X.

[Guy Arseneault]

I just did a file compare of my ver9 post that I used to update to X and my current post I'm using for X2 MR1 SP1 and the only difference was quotation marks and dollar signs.

[Jim Evans from CNC Software]

Guy,

 

Roger is pointing you in the right direction (FMT assignments for IJK are needed). There was a bug introduced where the IJK auto format by MP was broke which is causing the problem with i$ output now.

 

Read my posts in this thread it will explain it with a little more detail.

 

ijk format problem

[Guy Arseneault]

Do I need to do something else?

 

 

pcir$ # Circular interpolation

n$, sgplane,e$

if plane$ = 0, n$, sccomp, sgcode, *x$, *y$, z$, *iout$, *jout$, kout$, pfr,e$

if plane$ = 1, n$, sccomp, sgcode, x$, *y$, *z$, iout$, *jout$, *kout$, pfr,e$

if plane$ = 2, n$, sccomp, sgcode, *x$, y$, *z$, *iout$, jout$, *kout$, pfr,e$

[Guy Arseneault]

Read your post Jim and did what Roger stated to do

quote:

---

What 'fmt's are assigned to i$, j$, k$ ?

 

 

fmt I 2 i$ # Arc center description in X

fmt J 2 j$ # Arc center description in Y

fmt K 2 k$ # Arc center description in Z

---

and BINGO it worked.

 

Thanks again to Roger and Jim for your assistance.