arc program output

[dan m]

I am sure this is a easy fix but for some reason it has me stumped. when i use circle mill i want my program to do the complete circle in 1 line using x y i j right now it is breaking the arc's. I have tried making changes in the control def but when i post the program I don't see any changes.

[Kannon]

stupid question...

 

whats the benefits of breaking it in quandrants anyway?

 

Accuracy?

[Guest]

dumber question.

 

Do you have "Allow 360 Degrees Arcs" checked?

[dan m]

yes john I do have "Allow 360 Degrees Arcs" checked. I'm wondering if it's somthing in my arc center type

[gcode]

How old is your post?? If its a V8 or V9 upgraded

to X2, it may not be accepting commands from

the control defintion?? You may need to open the post and flip the switches in there.

[dan m]

i have tried changing in both places. and of course i broke the #1 rule of backing up my original info now when it outputs arcs it is just using I's and J's without the x and y

[dan m]

this is what I am currently getting

 

N100 G0 G90 X-3.821 Y-26.5 S1069 M3

N110 G43 H31 Z.25

N120 Z.1

N130 G1 Z-.04 F1.07

N140 G3 X-6.179 I-1.179 J0.

N150 X-3.821 I1.179 J0.

N160 G1 Z.1

N170 G0 Z.25

[gcode]

That's godd code.. its a full circle broken into

2 180° arcs

[Kannon]

do you have..

 

start at center checked in your circle mill parameters?

[Guest]

I got this

 

code:

---

 G0 G90 G54 X0. Y0. S14000 M3

G43 H234 Z2. M8

Z.1

G1 Z-1. F35.

Y.1875 F155.

X.0485 Y.3686

G3 X0. Y.375 I-.0485 J-.1811

I0. J-.375

X-.0485 Y.3686 I0. J-.1875

G1 X0. Y.1875

Y0.

G0 Z.25

---

Have you tried a different machine or post?

 

Is this an older post Dan, if so, from what version originally?

[dan m]

Kannon,

I don't have start at center checked.

 

Gcode,

I understand that will work but this is for a tosheba boring mill and I am tring to get the gode to look like what the operators are used to looking at.

ex.

N100 G0 G90 X-3.821 Y-26.5 S1069 M3

N110 G43 H31 Z.25

N120 Z.1

N130 G1 Z-.04 F1.07

N140 G3 X-3.821 Y-26.5 I-1.179 J0.

N150 G1 Z.1

N160 G0 Z.25

[dan m]

John this is a post I started butchering a while ago and can't remember which one. It was probably the mpmaster

[Kannon]

here is what I get now after a little post mod.

 

code:

---

N104 T1 M6

N106 G0 G90 G54 X-3.821 Y-26.5 S5000 M3

N108 G43 H1 Z.1

N110 G1 Z0. F32.

N112 G3 X-3.821 Y-26.5 I-1.179 J0. F64.

N114 G1 Z.1 F32.

N116 M5

N118 G90 G00 G53 Z0.

N120 M30

---

I checked my post to..

code:

---

do_full_arc : 1     #Allow full circle output? 0=no, 1=yes  

---

and switched this..

code:

---

pcirout       #Output to NC of circular interpolation                                

pbld, n, sgplane, sgcode, pwcs, pccdia, pxout, pyout, pzout, pcout, parc,

pfr, pcan1, e

---

to..

code:

---

 pcirout       #Output to NC of circular interpolation                                

pbld, n, sgplane, sgcode, pwcs, pccdia, pfxout, pfyout, pzout, pcout, parc,

pfr, pcan1, e

---

its just forcing out the X and Y..

 

dont know if its proper, but gives me the code your looking for.

[dan m]

that did it thanks for all the help

[Kannon]

glad it worked