Variaxis Mazatrol and G43.4

[MLS]

Anyone know if G43.4 is a standard feature for a Variaxis 730 with a Mazatrol Matrix or an option?

 

And if so does it work well?

[robk]

Not sure if it's standard or not, but our 730 does have it. I have never used it on a Variaxis though. All my programs for the Variaxis use dynamic offset (G54.2), and all my programs for the Integrex use tool tip (G43.4).

[Mic]

A friend of mine works on a Variaxis 630 and this machine has both G54.2 and G43.4 but he has never used it because our local Mazak reseller only can support/help with mazatrol programming. They don't know anything about G-code programming for this machine:( Does any of you Mazak guru's out there have some sample code we could see?

[robk]

%

(MACHINE: MAZAK 730)

(----)

(OP; 30)

(REV--)

(DATE: 07/18/08)

(FILE: R040)

(ROBK)

(MATERIAL-AMS5663 NI ALLOY)

(SFM=4000)

(FPT=.004)

(DOC=.060)

()

(****ATTENTION****)

(****ATTENTION****)

(****ATTENTION****)

(****ATTENTION****)

(RUN WITH BLOCK DELETE 7 ACTIVE TO SKIP TLO MEASUREMENT AT BEGINNING OF EVERY SEQUENCE)

(****ATTENTION****)

(****ATTENTION****)

(****ATTENTION****)

(****ATTENTION****)

()

()

()

GOTO#3901 (USE PART COUNTER TO SEARCH FOR SEQUENCE NUMBERS)

()

()

()

G90 G80 G00 G17 G40 G98 G49

( )

(T1 2.00 DIA ENDMILL-CERAMIC)

()

()

(.350 STK)

N40 T1 M06

#3901 =#4114

G90 G80 G00 G17 G40 G98 G49 G94

/7 M33 (LASER ON)

/7 G65 P9862 B1. T1 S3000

/7 M34 (LASER OFF)

G91 G28 Z0.

M43 M46 (UNLOCK A AND C AXIS)

G00 G90 G54.1 X1.7737 Y1.7252 A-74.273 C25.785

S7639 M03

G54.2 P1

G43 Z18.2705 H01

G61.1 (HIGH ACCURACY MODE)

Z14.2705

G93 G1 X1.6834 Y1.2334 Z14.2726 F183.327

X1.5956 Y.9693 Z14.2748 F329.361

X1.4384 Y.7397 Z14.2786 F329.404

X1.224 Y.5622 Z14.2839 F329.278

X.969 Y.4508 Z14.2903 F329.332

X.6931 Y.414 Z14.2971 F329.236

X.694 C28.554 F136.543

X.6946 C31.276 F138.9

X.6953 C33.96 F140.867

X.6956 C36.611 F142.62

X.696 C39.238 F143.923

X.6962 C41.846 F144.971

X.6963 C44.441 F145.697

C47.028 F146.148

X.696 C49.612 F146.318

X.6959 C52.2 F146.092

X.6956 C54.796 F145.642

X.6951 C57.405 F144.916

.

.

.

.

.

X-.3036 Y2.3439 C66.13 F513.913

X-.4075 Y2.3854 C65.58 F524.572

X-.5008 Y2.4227 Z13.8571 A-74.273 C65.049 F558.654

X-.5783 Y2.4545 C64.562 F629.615

X-.6371 Y2.4801 C64.136 F748.981

X-.676 Y2.4989 C63.781 F944.394

X-.6943 Y2.5104 C63.504 F1287.334

X-.6936 Y2.5142 C63.304 F1865.112

X-.6943 C60.399 F128.801

X-.6951 C57.541 F130.919

X-.6954 C54.723 F132.777

X-.6959 C51.935 F134.205

X-.696 C49.171 F135.37

X-.6962 C46.423 F136.159

X-.6963 C43.685 F136.656

X-.6961 C40.951 F136.856

X-.696 C38.214 F136.706

X-.6955 C35.469 F136.308

X-.6951 C32.708 F135.518

X-.6943 C29.926 F134.495

X-.6937 C27.113 F133.013

X-.6926 C24.264 F131.333

X-.6914 C21.368 F129.202

X-.69 C18.416 F126.751

G94 Z14.8571 F91.7

G0 Z18.8571

M98 P9500

G64

G91 G28 Z0.

G91 G28 X0. Y0. A0. C0. M05

M01

#3901 =1 (FORCE SEQUENCE #1 INTO THE PARTS COUNTER)

M30

%

[MLS]

Thanks for the replies.

 

We have everything set up from machine origin but that G54.2 is a nice feature. Shouldn't G43.3 work with that as well?

 

I just really want to get rid of the Inverse time feedrates.

 

Maybe I will just try G43.4 and see.

 

Rob, just out of curiosity, why do you not use the G05P02?

[robk]

quote:

---

Rob, just out of curiosity, why do you not use the G05P02?

---

That's because that one slipped by me. Thanks for pointing that out. I'll have to try it in the future. Is there anything I need to look out for or is it as simple as the manual makes it sound? Just turn it off with G05P0? Thanks again

I don't think that G43.4 will work with G54.2, but I have been wrong many times in the past. I do prefer to see a standard feed rates also, but my UG post is tuned in pretty well and inverse feed rate is not a problem.

[Mic]

Hi Rob

 

Some new questions

 

M43 M46 (UNLOCK A AND C AXIS)

G00 G90 G54.1 X1.7737 Y1.7252 A-74.273 C25.785

S7639 M03

G54.2 P1

G43 Z18.2705 H01

G61.1 (HIGH ACCURACY MODE)

Z14.2705

G93 G1 X1.6834 Y1.2334 Z14.2726 F183.327

 

I can see that you first activate G54.2 after the initial positioning of XYAC. Will your G43Z approach then still be in a straight vertical line? What is the difference between G54 and G54.1?

[MLS]

Rob,

 

Well I will ask about using both when(or if) the tech calls me back.

 

G05 P02 is pretty simple. G05 P0 turns it off as you said. The only other thing is no M-codes or cycles are allowed while in it. I think that is about it if I remember correctly.

 

 

N100T01M06

(----------------------------------------)

( TL#1 2.00 DIA FACEMILL .12CR .50LOC 7.80ST 3FL)

(----------------------------------------)

G0G17G90G94G40

T46

/M501

S9000M03

G90G54

M46

M43

G0A0.C0.

G0X-12.2502Y1.0951

G43Z13.41H01M08

G61.1

G05P02

G0X-12.2502Y1.0951

Z13.41

Z9.61

G1Z9.31F250.

X10.2498

G3X10.2498Y2.3617I0.J.6333

G1X-10.2502

G2X-10.2502Y3.6284I0.J.6333

G1X10.2498

G3X10.2498Y4.895I0.J.6333

G1X-10.2502

G2X-10.2502Y6.1616I0.J.6333

G1X10.2498

G3X10.2498Y7.4283I0.J.6333

G1X-10.2502

G2X-10.2502Y8.6949I0.J.6333

G1X12.2498

Z9.51

G0Z13.31

G05P0

M05M09

G0G28G91Z0.

G0G28G91A0.C0.

M501

M01

N110T46M06

[robk]

quote:

---

I can see that you first activate G54.2 after the initial positioning of XYAC. Will your G43Z approach then still be in a straight vertical line?

---

Getting to the G43 line will not be straight-- the machine will take the shortest route to get there, but the next z movement following the G43 line will be in the straight vertical line. I feel safer calling G54.2 above the part just in case.

 

quote:

---

What is the difference between G54 and G54.1?

---

That must have been my fat fingers doing something when I was copying & pasting. The G54.1 should be G54.1P1 (In my case). Those are the extended work offsets which we have 600. Therefore we could go all the way up to G54.1P600.

 

Shoot me an email Michael and I will send you a .pdf of a .eia programming manual for the Variaxis using Matrix control. I'm out of here in a few minutes, so I'll send it your way tomorrow if you want me to.