NC file name = program#

[arsson]

I use X3 and mpheid5 posts mill.

 

A set the NC file name to a number and I want it to change the program number in NC file as same.

 

I cant find any answer for this in forum or helpfile.

[Bruce Caulley]

Search for and download the X+ utility. This will do it for you.

 

Bruce

[Mgrenier]

Arsson,

 

Look in the pheader section of you post and make sure you have a line that looks like the one bellow.

 

code:

---

 

pheader$ #Call before start of file

if met_tool$ = one, #Metric constants and variable adjustments

[

ltol$ = ltol_m

vtol$ = vtol_m

maxfeedpm = maxfeedpm_m

]

if usecanned = yes$, pusecannedyes

else, pusecannedno

result = nwadrs(srotary, cabs)

result = nwadrs(srotary, cinc)

result = nwadrs(srotary, indx_out)

 

# "%"

sav_spc = spaces$

spaces$ = 0.

"O", sprogname$,e$ <--------- Here is the line

.....

---

[arsson]

This is my pheader$

 

code:

---

pheader$ # File header

#"Program Name - ", progname

#"Program Time - ", time

#"Program Date - ", date,"(Day:Month:Year)"

 

"0", "BEGIN PGM ",progno$,"MM",e$

---

When i change program number in toolpath it work correct. But i whant the posts to change to right program number, same as the name of nc file

[Mgrenier]

Change this line:

"0", "BEGIN PGM ",progno$,"MM",e$

 

to:

"0", "BEGIN PGM ",sprogname$,"MM",e$

 

Hope that helps

[alma999]

marting right, but need this too:

 

code:

---

peof$            #End of file for non-zero tool           

.

.

.

n$, "END PGM ",sprogname$,"MM",e$

---

[CNC PRO]

Under settings - System Configuration - Toolpath Manager NC File, set it to MCX file name.

 

This saves your NC file to whatever you saved your MC file.

[Jayson Kramer]

Right click in the "ops Manager" Go to Edit Selected operations then "Change NC Name" for changing the program Name.

Then go back and under that is the option to "Change program #" this will change the "O1111" for example at the top of your program.

 

this can be done for a group of operations or just one.

[arsson]

YES it work. I happy :-)

This is exempel how I work

 

*Open a 3D modell.

*save it with drawing number and description MCX

*Prepare it for toolpath

*create toolpath and got question to choose a NC name.

*Run postprocessor and it save the file automatic on the network with same NC file name and programe name