Decimal tool number

[Mgrenier]

Hello all,

 

Is it possible to have mastercam get a decimal tool number? Ex: T90.26

 

This is fou our entegrex that has that kind of tool calls.

[Guest]

T90 OK, but what is the 26?

[Ron Branch @ Verisurf]

Yes it is possible, but since In-House sold us the post we use I can not share what they did. Please email them and they can explain to you how to add it to the post.

 

John Mazaks use a Letter in the Conversation side of the machine called Mazatrol. One tool on our Integrex could have 50 different names or positions for the same tool. It does not use all the letters of the alphabet, but close. Not you call the tool but the .XX is the letter equivalent in NC code is all.

 

HTH

[alma999]

With your example: (T90.26)

 

Toolpath parameterts/Tool#: fill with 9026 (multiply tool number by 100)

 

Modify your post:

 

* - add this line

( - existing line

code:

---

.

(# --------------------------------------------------------------------------

(# Format statements - n=nonmodal, l=leading, t=trailing, i=inc, d=delta

(# --------------------------------------------------------------------------

 

(fs2 10 0.2 0.2 #Decimal, absolute, 2 place

.

(# --------------------------------------------------------------------------

(# Toolchange / NC output Variable Formats

(# --------------------------------------------------------------------------

 

(fmt 4 t$ #Tool number

*fmt 10 tdec #Decimal tool number - this is the new variable

.

 

*tdec = t$/100 # dividing tool number by 100

.

---

Replace all t$ with tdec and save post.

[crazy^millman]

Alma good suggestion since Mazatrol does not use the H & D no problems with using that tool number method.