G68 and HPCC Error at Fanuc 18i-MB control

[peon]

The posted code below works excellent on the Johnford with a Fanuc 18i-MB controller UNTIL we add a G68 code for rotation. Adding a G68 generates a 5012 error (G05 P10000 Illegal Startup). If we remove the HPCC blocks, all will work fine. After doing some reading, I believe the G68 should work fine with the HPCC code. What am I missing from the following program? Any suggestions?

%

O0000(G68_HPCC)

(PROGRAM FOR JOHNFORD FANUC 18I-MB)

(DATE - APR. 06 2011)

(TIME - 12:04 PM)

(T1 1/4 FLAT )

(T2 1/8 FLAT)

G20

G0G17G40G49G80G90

(FIRST SAMPLE CONTOUR)

T1M6

S12450M3

G4X320. ---------------------------WARMS TOOL

G65P9902A3.H1R.0002S12450W0.Z0.-----TOOL SETTING PROBE

M7

G0G90G54X0.Y.125A0.S12450M3

G43H1Z1.T2

G05P10000R7-------------------------HPCC CODE

Z-.475

G1Z-.5F60.

X1.

G0Z1.

G05P0-------------------------------HPCC CANCEL

M9

M5

G91G28Z0.

G28Y0.

M01

(SECOND SAMPLE CONTOUR)

T2M6

S15200M3

G4X450.----------------------------WARMS TOOL

G65P9902A3.H2R.0002S15200W0.Z0.----TOOL SETTING PROBE

M7

G0G90G54X-.0625Y0.A0.S15200M3

G43H2Z1.T1

G05P10000R7-------------------------HPCC CODE

Z-.225

G1Z-.25F40.

Y1.

G0Z1.

G05P0-------------------------------HPCC CANCEL

M9

M5

G91G28Z0.

G28Y0.

G28X0.Y0.

G90

M30

%

[Newbeeee™]

No experience with G05P1000.

But with G05.1Q1, this has to be before the G43 line.

When it's cancelled (at the end of tool), a G49 has to follow it.

 

%

O0666

( CUSTOMER )

( DESCRIPTION )

( DRG NO: )

( ISSUE NO: )

( OP NO: )

 

( SUBS USED PO0000 - PO0000 )

 

G17 G21 G40 G49 G69 G80 G90 M05

 

M00 ( NEW PROGRAM )

( USE BLOCK SKIP TO DISABLE G05.1 HSM )

 

(G54 DATUM)

G10G90L2P1X0Y0Z0

 

M1

 

N0101 T1 M6

M1

( 10MM DIA CARBIDE SLOTDRILL )

( CONTOUR )

G10G90L12P1R5.

/G05.1 Q1

 

G54 G0 G17 G40 G49 G69 G80 G90 X-13.822 Y39.05 S5000 M3

M8

G43 Z100. H1

Z25.

Z2.

G1 Z-5. F250.

G41 D1 X-21.322 F1500.

G3 X-13.822 Y31.55 R7.5

G1 X9.916

Y-23.588

X-37.56

Y31.55

X-13.822

X-12.822

G3 X-5.322 Y39.05 R7.5

G1 G40 X-12.822

G0 Z100. M9

G28 Z100. M19

G05.1 Q0

G49

X0.

G28 Y39.05

T1 M6

 

M30

%

[peon]

Thank you Newbeeee! That certainly helped me get on track. I made some post mods and everything works well with the following code.

 

%

O0000(G68_HPCC)

(PROGRAM FOR JOHNFORD FANUC 18I-MB)

(DATE - APR. 07 2011)

(TIME - 11:41 AM)

(T1 1/4 FLAT )

(T2 1/8 FLAT)

G20

G0G17G40G49G80G90G54

(FIRST SAMPLE CONTOUR)

T1M6

S12450M3

G4X320.

G65P9902A3.H1R.0002S12450W0.Z0.

G05P10000R7

M7

G68X0.Y0.R180. ---------------(ROTATION ON)

G0X0.Y.125

S12450M3

G43H1Z1.

T2

Z-.475

G1Z-.5F60.

X1.

G0Z1.

G69 --------------------------(CANCELED ROTATION)

G05P0

M9

M5

G91G28Z0.

G28Y0.

G49

M01

(SECOND SAMPLE CONTOUR)

T2M6

G90

S15200M3

G4X450.

G65P9902A3.H2R.0002S15200W0.Z0.

G05P10000R7

M7

G68X0.Y0.R180. ---------------(ROTATION ON)

G0X-.0625Y0.

S15200M3

G43H2Z1.

T1

Z-.225

G1Z-.25F40.

Y1.

G0Z1.

G69 --------------------------(CANCELED ROTATION)

G05P0

M9

M5

G91G28Z0.

G28Y0.

G49

G90

M30

%

[Newbeeee™]

Glad to be of service