W axis macro variables

[T-guy]

Hey all, does any one know what variable is used for the "W" axis? I have a Kuraki/Fanuc15m with a "W" axis Quill. I am creating a macro to measure tool lenght offsets automaticly, but, I can not find the variable. I looked thru the manuals for this machineand even contacted Fanuc.

 

Help me 'O-mighy ones of the net!

[crazy^millman]

Ok that is a new one. Hey what version of Mastercam are you trying to write to work with. I might be able to help you if you tell me the Version you are using.

 

Crazy Millman

[Harryman]

Yo, Mr T, could you clarify the question a bit more? Are you looking for a system variable, common, local...?

 

I'm a huge fan of macros and am very interested to hear all about what you're trying to do.

[mayday]

the vaiable in a costom macro body for W is #23

 

If your looking to read in axis position to load

in your TL offset page

 

#5041 1st axis

#5042 2nd axis

#5043 3rd axis

#5044 4th axis

#5045 5th axis

#5046 6th axis

 

here is a sample for reading Z position

 

O0001(TOOL-SETTING PROGRAM);

N1#100=1(set #100 equal to first tool);

N2DO1;(beginning of loop);

N3T[#100](select tool);

N4M6(tool change)

N5#3006=1(SET TOOL OFF 1.0 BLOCK - comment line for operator);

N6#[2000+#100]=#[5023]-1.0(PUT MACHINE Z - 1" INTO OFFSET);

N7G0G91G28Z0.0(rapid to Z axis zero return);

N8#100=#100+1(increment to next tool);

N9END1(end indefinite loop);

N10G90(switch back to absolute coordinates)

M30

%

sample to indicate a bore and load X,Y poition into

offset page,simple by pushing cycle start

 

O0001(INDICATING PROGRAM);

T25 M6

G90G80G40G49G17G20;

G0G57X0Y0B0

G43H25Z10.;

X-5.25 Y3.75

#3006=1(INDICATE);

#101=#5041;(SETS NEW X COORDINATE)

#102=#5042;(SETS NEW Y COORDINATE)

G0Z10.(RETURN TO INITIAL POINT)