custom drill cycles & probing

[MIL-TFP-41]

Right now we are running inspection plus & I have the custom drill cycles set up for probing. As you can see from the attached screenshot, I have a separate cycle for probing an X surface, Y surface & Z surface. It works great, except it ties up 3 of my custom cycles instead of one. Looking at the second screenshot, I could easily add a "Y Nominal" field and a "Z Nominal" and consolidate it into one cycle (with the post throwing an error if they have a number in more than one field....just curious as to how others are approaching this.

[Craig-B]

Under your offset update, You can activate that window as a switch and do (1.0=X 2.0=Y 3.0=Z) Then in the post check for that value and use if then to select the output for single surface. 

[EX-wccprogrammer]

I wrote my post to use linear movement for probing.  That way I have control over approach distances and can probe vectors.  The vector determines what is being measured.  If the vector is purely in the Y axis, I get Y measurement.

[MIL-TFP-41]

I wrote my post to use linear movement for probing.  That way I have control over approach distances and can probe vectors.  The vector determines what is being measured.  If the vector is purely in the Y axis, I get Y measurement.

 

How are you doing that? are you using custom drill cycles or something else?

The way I have it set up gives control over approach distances & clearance heights....however having control over the vector would be even better.

[EX-wccprogrammer]

I have written logic that identifies the tool as a probe, and written the code that analyzes the vector of the move.  Programming is as simple as constructing vector lines where I want to probe, and programming as 3D contour.

[MIL-TFP-41]

Nice....that way backplot is going to show what the tool is actually doing. How about web & pockets, circles & bosses?

[EX-wccprogrammer]

I can instruct (using keywords) the post what I am trying to measure.  I could simply type 'WEB' in the comment box for the toolpath that measures a web.

[EX-wccprogrammer]

To find midpoints of features like pockets or bosses, the toolpath would have pairs of probe vectors (opposite sides of the feature).  The direction of the vector pairs are analyzed, so the post knows if OD or ID is being measured.

[rn8849]

Right now we are running inspection plus & I have the custom drill cycles set up for probing. As you can see from the attached screenshot, I have a separate cycle for probing an X surface, Y surface & Z surface. It works great, except it ties up 3 of my custom cycles instead of one. Looking at the second screenshot, I could easily add a "Y Nominal" field and a "Z Nominal" and consolidate it into one cycle (with the post throwing an error if they have a number in more than one field....just curious as to how others are approaching this.

I see in your second screenshot that you have been able to customize the "Apply custom drill parameters" label, I know how to configure the standard ones, would you please tell me how to configure the labels for the Custom Parameters? I tried adding in more fields starting with 12 and going up to 20 but they don't appear anywhere like they do when I alter the ones numbered from 1 to 11.

 

Thanks in advance

[Guest]

As an example, Custom Cycle 13 could have something like this

[drill cycle 13 custom parameters]
1. "Y SLOT PARAMETERS"
2. ""
3. ""
4. ""
5. "(J) Y INCREMENATL APPROACH"
6. ""
7. "(S) NOMINAL WIDTH"
8. "(W) WORK OFFSET"
9. ""
10. ""
11. ""

After you change them in the post, make sure you reload the machine def so they show up

 

[crazy^millman]

http://www.emastercam.com/board/index.php?showtopic=17722

 

http://www.emastercam.com/board/index.php?showtopic=15291

 

http://www.emastercam.com/board/index.php?showtopic=28834

 

www.emastercam.com/board/index.php?showtopic=31183

 

See if any of these help.

[rn8849]

As an example, Custom Cycle 13 could have something like this

[drill cycle 13 custom parameters]
1. "Y SLOT PARAMETERS"
2. ""
3. ""
4. ""
5. "(J) Y INCREMENATL APPROACH"
6. ""
7. "(S) NOMINAL WIDTH"
8. "(W) WORK OFFSET"
9. ""
10. ""
11. ""

After you change them in the post, make sure you reload the machine def so they show up

 

Thank you JParis, that is exactly what I needed. What I was missing was adding another line including "custom parameters" below the drill cycle definition.

 

[drill cycle 9]

1. "Threadmilling Cycle"

3. ""

7. "drill "

8. ""

9. ""

10. ""

11. ""

[drill cycle 9 custom parameters]

2. "Subprogram Number"

 

so this works properly...

[rn8849]

http://www.emastercam.com/board/index.php?showtopic=17722

 

http://www.emastercam.com/board/index.php?showtopic=15291

 

http://www.emastercam.com/board/index.php?showtopic=19194

 

http://www.emastercam.com/board/index.php?showtopic=28834

 

www.emastercam.com/board/index.php?showtopic=31183

 

See if any of these help.

Ron, thank you... these seem to pertain to the definition of the cycle, which I was ok on, I was baffled as to how to configure the text in the popup window for the drilling parameters, JParis answered my question above. I sure appreciate that you guys are out there and willing to help!

-Gary

[Tim Johnson]

Right now we are running inspection plus & I have the custom drill cycles set up for probing. As you can see from the attached screenshot, I have a separate cycle for probing an X surface, Y surface & Z surface. It works great, except it ties up 3 of my custom cycles instead of one. Looking at the second screenshot, I could easily add a "Y Nominal" field and a "Z Nominal" and consolidate it into one cycle (with the post throwing an error if they have a number in more than one field....just curious as to how others are approaching this.

I use one custom cycle for single surface probing using dwell$ as my switch. 0 = transfering work offsets, 1 = y-, 2 = x-, 3 = y+, 4 = x+, 5 = z, 6 = z check for obstacles.